|
[Sponsors] |
[ANSYS Meshing] Dynamic Mesh with Inflation Layer |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
September 19, 2012, 03:33 |
Dynamic Mesh with Inflation Layer
|
#1 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Hello I'm a final year student of civil engineering degree. I'm doing a CFD simulation of the Vortex-Induced-Vibration on a circular cylinder.
I made an UDF and I made some simulations with dynamic mesh, but i have one question: Is it possible to make a dynamic mesh with inflation layer (orthogonal mesh)? I think it's only possible with TRI-mesh ( I read it on Fluent user's manual) but I read some papers of sciencedirect, in which the author used orthogonal mesh to do some dynamic simulations. (I used Juan B.V. Wanderley a,, Gisele H.B. Souza b, Sergio H. Sphaier a, Carlos Levi 2008 paper. www.sciencedirect.com) |
|
September 19, 2012, 03:38 |
|
#2 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Sorry I try to upload another picture. And I have to do it on the reply.
This picture is from the same paper. "In addition, the generated grid is locally orthogonal to the body surface to facilitate the implementation of the boundary condition on the body. In order to concentrate grid points at the wake region behind the cylinder and body surface, an exponential stretching is used in both circumferential (x) and radial (Z) directions. In each time step, the entire grid is regenerated after the body displacement, so that the external boundary is kept fixed" this is a part of the text in which the author explains the grid. I need some help please . I know how to make tri-mesh dynamic mesh, but not orthogonal. (i think its better and more accurate in order to get the best results). Thanks. |
|
September 21, 2012, 03:19 |
|
#3 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Please I need some information. If this is impossible to do I need to know , because it's important not spending more time in this thing.
Thanks |
|
September 21, 2012, 03:21 |
|
#4 |
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
By Inflation you mean boundary layer mesh or you mean structured mesh?
|
|
September 21, 2012, 03:24 |
|
#5 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Inflation its the name that ansys meshing uses to do the Boundary Layer mesh ( I think that Boundary Layer its the name Gambit give to it).
Yes I mean some kind of structured mesh in order to do the mesh more fine in the boundary to capture better all the effects. I'm only capable to run a mesh with tri-elements in the region that moves with the cylinder. |
|
September 21, 2012, 04:46 |
|
#6 | |
Super Moderator
|
Quote:
|
||
September 21, 2012, 04:54 |
|
#7 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Its only one way simulation ( inlet boundary to pressure outlet) ( the wind go from left to right)
I divided the mesh in 3 zones, Inlet zone (structured) moving zone (unstructured) and outlet zone (structured again). It's what you have asked me? Thanks for answered me. |
|
September 21, 2012, 08:19 |
|
#8 | ||
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
Quote:
Quote:
1. Smoothing 2. Layering 3. Remeshing "Smoothing" works for both structured(which you are naming as "orthogonal") and unstructured meshes but it is generally recommended for unstructured meshes, "Layering" purely works for structured meshes while "Remeshing" method works only for unstructured meshes |
|||
September 21, 2012, 08:30 |
|
#9 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Thank you for the response. I didn't know smoothing method was capable to make dynamic mesh with orthogonal-elements. I will make a new mesh and I will try.
P.S. The pictures isn't from my work, there are from the Paper i used to compare my results. I used a combined mesh, with orthogonal mesh in the zone which doesn't move and tri-mesh where the cylinder is able to move. I will upload pictures from my mesh later. |
|
September 21, 2012, 08:35 |
|
#10 | ||
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
Quote:
Quote:
If you are using structured(orthogonal/hexa) mesh in the boundary layer and unstructured mesh in the outer part then you have to define two "Fluid Zones" in the mesh i.e one for the boundary layer and one for the outer layer....for structured(orthogonal/hexa) boundary layer mesh toggle on layering and for outer unstructured mesh toggle on smoothing and remeshing |
|||
September 21, 2012, 08:41 |
|
#11 | |
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
Quote:
|
||
September 21, 2012, 08:51 |
|
#12 | |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Quote:
dont need the cylinder rotate or move in longitudinal . The vortex induced vibration in vertical mode its something like this http://www.youtube.com/watch?v=aOfqdQs66jA |
||
September 21, 2012, 08:56 |
|
#13 | |
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
Quote:
|
||
September 21, 2012, 08:58 |
|
#14 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
thank you thank you thank you
I'll try and i will show you the results... (maybe in 2 weeks) Thank you again! |
|
September 24, 2012, 07:30 |
Help
|
#15 |
New Member
CFD man
Join Date: Sep 2012
Location: Earth
Posts: 12
Rep Power: 13 |
Hi grayback87
Please send your grid for me. (fluent.workshop@gmail.com) I can correct it for you. I suggest doing that with Gambit software.because you must have two separate zone. |
|
September 29, 2012, 01:06 |
|
#16 |
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
what's the progress? updates please....
|
|
September 29, 2012, 12:59 |
|
#17 |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Hi, finally i did it ! It moves without problem.
But Now I'm doing some benchmarks, I mean, I'm comparing with the literature, Cd vs Re in stationary and other things. I used Remeshing and it works very fine |
|
September 29, 2012, 15:39 |
|
#18 |
New Member
CFD man
Join Date: Sep 2012
Location: Earth
Posts: 12
Rep Power: 13 |
Hi
I suggest that you try to use Layering Method. (with another Mesh) Layering method is very rapid and Remeshing method is slower than layernig. In curvilinear boundary (such as circle) you can use the constant ratio (not constant height) method of layering.
__________________
My blog is (Fluent Software Training Center): http://fluent-workshop.blogspot.com |
|
September 30, 2012, 05:17 |
|
#19 |
Senior Member
Join Date: Mar 2011
Location: Germany
Posts: 552
Rep Power: 20 |
did you also use smoothing? ?did you also move the boundary layer mesh?
|
|
October 3, 2012, 04:00 |
|
#20 | |
New Member
Join Date: Dec 2011
Location: Spain
Posts: 25
Rep Power: 14 |
Quote:
The last picture has the statistics of my mesh, number of elements and skewed cells. I make some dynamic test to my mesh and It works fine, but, I need to make a very good mesh beacuse I have to make a good Cd Vs Re Plot, because the cylinder its only a little part of my final project of my degree in civil engineering. If someone see anything wrong please make me know it. (sorry, I'm not very skillfull with english language) |
||
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
how to set periodic boundary conditions | Ganesh | FLUENT | 15 | November 18, 2020 06:09 |
[snappyHexMesh] SnappyHexMesh - no layer added | bejbro | OpenFOAM Meshing & Mesh Conversion | 5 | February 1, 2020 20:05 |
3D Hybrid Mesh Errors | DarrenC | ANSYS Meshing & Geometry | 11 | August 5, 2013 06:42 |
[snappyHexMesh] snappy hangs while layer generation | bastil | OpenFOAM Meshing & Mesh Conversion | 3 | October 29, 2010 07:19 |
[snappyHexMesh] Boundary layer generation problems | ivan_cozza | OpenFOAM Meshing & Mesh Conversion | 0 | October 6, 2010 13:47 |