CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[GAMBIT] hexahedral mesh for cyclone

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree8Likes
  • 1 Post By -mAx-
  • 1 Post By -mAx-
  • 1 Post By -mAx-
  • 1 Post By -mAx-
  • 1 Post By -mAx-
  • 1 Post By -mAx-
  • 1 Post By -mAx-
  • 1 Post By -mAx-

Reply
 
LinkBack Thread Tools Display Modes
Old   December 6, 2012, 06:45
Default hexahedral mesh for cyclone
  #1
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Hi
I'm trying to mesh a cyclone that is consisted of three volumes (1-tangential inlet,2-upper cylinder(gas outlet) 3-cyclone body(frustum+cylinder) with hexahedral elements.all faces were meshed with hex element and pave type.I can not mesh volumes 2,3 with hexahedral elements and cooper type. Because i can't specify true source faces. would yu please help me to mesh this cyclone.
Thanks in advanced.
http://postimage.org/image/6afrf11ct/
nabaen is offline   Reply With Quote

Old   December 6, 2012, 07:56
Default
  #2
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
Because the red surrounded volume cannot be meshed directly as cooper
You need to do some splits.
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   December 25, 2012, 02:42
Default
  #3
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Hi,
Thank you so much for your reply .I could finally mesh my cyclone with hexahedral type . I defined a virtual face to split two volumes. My fluent case dose not converge .I guess the cyclone meshes are not suitable.
1-Can virtual face interrupt the gas flow?(It is not defined as a zone or boundary. Is it necessary to deifine this face?Can I ignore this virtual face?
2-I have 4 separated volumes 3 of them are cooper type and inlet is map type.what is your idea about the quality of meshes.Do you think cyclone mesh can be reason of model convergence problem ?
Thanks in advanced
nabaen is offline   Reply With Quote

Old   December 25, 2012, 02:51
Default cyclone mesh
  #4
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Hi,
Thank you so much for your reply .I could finally mesh my cyclone with hexahedral type . I defined a virtual face to split two volumes. My fluent case dose not converge .I guess the cyclone meshes are not suitable.
1-Can virtual face interrupt the gas flow?(It is not defined as a zone or boundary. Is it necessary to deifine this face?Can I ignore this virtual face?
2-I have 4 separated volumes 3 of them are cooper type and inlet is map type.what is your idea about the quality of meshes.Do you think cyclone mesh can be reason of model convergence problem ?
Thanks in advanced
http://axgig.com/images/54732507926098137654.jpg
nabaen is offline   Reply With Quote

Old   January 3, 2013, 02:31
Default
  #5
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
if your splits are well done, then split surfaces are defined as interior.
The question is why it is not converging?
Is your checkmesh successfull?
Do you have walls in fluent which are not predefined in gambit?
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   January 8, 2013, 02:41
Default
  #6
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
I made my geometry once more. This time I did not uninited the volumes.So it consists of 4 volumes. They are meshed by hexahedral type, so that these volumes can not be united. There are 3 faces (marked by red color in attached picture ) that make the problem.I have to define them as boundary ,otherwise it will be known as wall and will be an obstruction for fluid.I defined them as interior but Fluent didn’t accept this faces as interior. What boundary should I define for these faces?
http://upload.tehran98.com/img1/108gqx37aa9gw4mdlsm.jpg

By the way I have not predefined the walls in gambit.Because I think they will be known as wall by defult in gambit.
Thank you in advanced.

Last edited by nabaen; January 8, 2013 at 03:00.
nabaen is offline   Reply With Quote

Old   January 8, 2013, 08:57
Default
  #7
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
Quote:
Originally Posted by nabaen View Post
I have to define them as boundary ,otherwise it will be known as wall and will be an obstruction for fluid.I defined them as interior but Fluent didn’t accept this faces as interior. What boundary should I define for these faces?
http://upload.tehran98.com/img1/108gqx37aa9gw4mdlsm.jpg

By the way I have not predefined the walls in gambit.Because I think they will be known as wall by defult in gambit.
Thank you in advanced.
Gambit creates wall instead of interior (or internal) because your volumes aren t connected (if you select suc a surface, you will see there are 2 superposed surfaces).
Go to face / connect, and connect all.
It should fix the problem.
And yes, all outer surfaces which are not defined as BC, will be automatically set as wall
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   January 9, 2013, 00:32
Default
  #8
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Thank you so much for your kind reply.
I didn’t understand which faces should connect. I selected all faces and entered to connect but a warning resulted.
I united three of volumes.Now it is comprised of 2 volumes.Can I define the red face as “interface”?http://upload.tehran98.com/img1/hfymmj1mxn4fcptone.jpg
I was wondering if you could check my geometry?https://hotfile.com/dl/188146938/16c...metry.dbs.html
Thanks in advanced. and excuse me for repeated question.
nabaen is offline   Reply With Quote

Old   January 9, 2013, 02:01
Default
  #9
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
your volumes aren t conected and not splitted
-Split volume 4 with volume 3
If you check edges 18 & 22, you see that both edges are tangential at vertex 13. That will be generate skewness cells.
So you can sweep face 14 in y-direction with vector (0 0.001 0), and then merge both volumes.
Finally merge also faces which common edge is source of problem (edge 18)
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   January 10, 2013, 03:19
Default
  #10
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Thank you so much.
I split volume 4 with volume 3 as your guide. But face 9 &19 are still my problem .They will be known as wall in fluent and will obstruct flow gas to exit. What should I do?
http://upload.tehran98.com/img1/a6pfqvp4tyzodvwiih1.jpg
https://hotfile.com/dl/188303408/c14...metry.dbs.html
I wish all the best to you.
nabaen is offline   Reply With Quote

Old   January 10, 2013, 03:45
Default
  #11
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
I saw you defined face 9 as interface.
Delete this BC
If you did the same with face 19, delete the BC
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   January 10, 2013, 04:33
Default
  #12
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Quote:
Originally Posted by -mAx- View Post
I saw you defined face 9 as interface.
Delete this BC
If you did the same with face 19, delete the BC
Yes ,Interface is not true.But if these two faces put undefined will be known as wall(How can I solve this?)
nabaen is offline   Reply With Quote

Old   January 10, 2013, 04:44
Default
  #13
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
if volumes are well connected, then Gambit defined split surfaces as internal (but won't appear in the BC panel)
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   January 10, 2013, 05:05
Default
  #14
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Quote:
Originally Posted by -mAx- View Post
if volumes are well connected, then Gambit defined split surfaces as internal (but won't appear in the BC panel)
I am so sorry. It made me frustrated .
Do you mean is splitting volume 4 with volume 3 enough ?So I have to define face 8 as wall.
nabaen is offline   Reply With Quote

Old   January 10, 2013, 05:10
Default
  #15
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
if your surface 8 has to be a wall, then define it as wall, else Gambit will define it as internal
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   January 10, 2013, 05:30
Default
  #16
Member
 
Join Date: Dec 2012
Posts: 33
Rep Power: 4
nabaen is on a distinguished road
Only one more question.
you advised me to sweep face 14 (preventing skewness cells).It was done but an error Occurred in last stage(merging faces with same edge(edge 18)
nabaen is offline   Reply With Quote

Old   January 10, 2013, 05:40
Default
  #17
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,972
Rep Power: 30
-mAx- will become famous soon enough
both displayed surfaces have 90° angle....
Then it is not possible to merge them
I meant like that:
Sans titre.jpg
nabaen likes this.
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] Hexa mesh, curve mesh setup, bunching law Anorky ANSYS Meshing & Geometry 4 November 12, 2014 01:27
[ANSYS Meshing] Structured hexahedral mesh in workbench Chander ANSYS Meshing & Geometry 3 November 2, 2011 04:32
Hexahedral Mesh Generation software makotohonda Main CFD Forum 1 July 14, 2010 00:04
Tetrahedral and hexahedral mesh based on FVM kuang Main CFD Forum 0 July 20, 2008 04:52
Icemcfd 11: Loss of mesh from surface mesh option? Joe CFX 2 March 26, 2007 18:10


All times are GMT -4. The time now is 00:57.