CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[GAMBIT] meshing 3-D flat tube

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   December 9, 2012, 22:14
Default meshing 3-D flat tube
  #1
vrk
New Member
 
Ravi
Join Date: Dec 2012
Posts: 5
Rep Power: 4
vrk is on a distinguished road
Hello, I am trying to mesh a 3-D flat tube ( rectangular pipe with two semi-circular ends, please see fig. 1). I created and meshed the geometry in the following procedure:
1. created the inlet face1 (by creating vertices, please see fig. 2)
2. swept the face in Z-direction to create volume 1
3. created virtual edge on inlet face by joining vertices 3 & 4 and similarly on outlet face as well.
4. created virtual faces at inlet and outlet by joining the edges (please see fig. 3)
5. created virtual volumes by stitching faces ( please see fig. 4).
6.created edge nodes and meshed the virtual volumes individually.

I followed the above procedure so that i can get fine mesh near the upper and curved wall.

While specifying boundary conditions, I have to select two virtual faces (rectangular and quarter circle face) to give inlet and outlet B.C's.If i select face1 as inlet, fluent is not recognizing any mesh on it.

Is this the correct procedure for creating the mesh for this geometry?
Any help in meshing this geometry would be highly appreciated.

Thanks,
Ravi
Attached Images
File Type: bmp Fig 1.bmp (24.7 KB, 25 views)
File Type: jpg Fig 2.jpg (32.9 KB, 42 views)
File Type: jpg Fig 3.jpg (92.6 KB, 44 views)
File Type: jpg Fig 4.jpg (75.9 KB, 39 views)
vrk is offline   Reply With Quote

Old   December 10, 2012, 03:54
Default
  #2
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,992
Rep Power: 30
-mAx- will become famous soon enough
are you able to display your whole geometry (mesh) in fluent?
Question is if gambit exports all your volumes.
PS: I am pretty sur you have skewed cells in your face.2 , especially in neighborhood from upper edge (common with face.1)
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   December 10, 2012, 07:00
Default
  #3
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,946
Blog Entries: 6
Rep Power: 39
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
use triprimitve scheme for the corner faces and then volume> Hex > cooper
Far is offline   Reply With Quote

Old   December 10, 2012, 07:46
Default
  #4
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,946
Blog Entries: 6
Rep Power: 39
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
see this please. You need to implement the similar topology either by decomposition or using triprimitive scheme.
Attached Images
File Type: jpg tube001.jpg (74.2 KB, 44 views)
File Type: jpg tube002.jpg (75.8 KB, 33 views)
File Type: jpg tube004.jpg (75.9 KB, 35 views)
File Type: jpg tube003.jpg (83.7 KB, 37 views)
Far is offline   Reply With Quote

Old   December 10, 2012, 17:16
Default
  #5
vrk
New Member
 
Ravi
Join Date: Dec 2012
Posts: 5
Rep Power: 4
vrk is on a distinguished road
mAx,
Thank you very much for your reply. When i try to export the mesh in Gambit, it is giving me the warning sign "Volume. 1 is not meshed and is not exported". Also boundary conditions on Face. 1(velocity Inlet) and Face. 4 (Outflow) are not exported. Also in "Fluent-Boundary conditions", I can't see velocity Inlet and outflow b.c's. Please see Fig. 1 for the warning sign given by Gambit in Transcript window. In Fig. 2, I assigned the velocity inlet and out flow B.C.'s on both virtual faces (rectangular and quarter circle). I am not sure if this is the right procedure or not?
Is there any other way to mesh the geometry without creating virtual volumes and also i need to have a finer and smoother mesh near wall boundaries?

Thanks
Ravi
Attached Images
File Type: jpg Fig 1_Gambit mesh export warning.jpg (93.1 KB, 14 views)
File Type: jpg Fig 2_ Gambit mesh export warning.jpg (52.1 KB, 5 views)
vrk is offline   Reply With Quote

Old   December 10, 2012, 17:29
Default
  #6
vrk
New Member
 
Ravi
Join Date: Dec 2012
Posts: 5
Rep Power: 4
vrk is on a distinguished road
Far,
Many thanks for your reply with attached figures. Did you mesh the face with out splitting it? or did you split the face into rectangular face and quarter circle face and then meshed them separately?
Could you please tell me in detail how you created the geometry and meshed it.

Thank you.
Ravi
vrk is offline   Reply With Quote

Old   December 10, 2012, 23:57
Default
  #7
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,946
Blog Entries: 6
Rep Power: 39
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
I did meshing in ICEM and for just reference I post pics. Definitely if you want hexa meshing then you need to split the face into regular rectangular and quarter face (not necessarily the different volumes).

Here is the procedure for the Gambit ......
Case one : One volume and two faces.

Mesh that face with map and triprimitve mesh and then apply the volume meshing with option Hex+cooper.

Case II : Two volume and naturally two faces on both ends

Mesh rectangular face with normal map and hexa meshing methods
Mesh quarter volume by first meshing the quarter face using the triprimitive and side faces with map meshing and then volume meshing using Hexa + cooper scheme.
Far is offline   Reply With Quote

Old   December 11, 2012, 02:21
Default
  #8
Super Moderator
 
-mAx-'s Avatar
 
Maxime Perelli
Join Date: Mar 2009
Location: Switzerland
Posts: 2,992
Rep Power: 30
-mAx- will become famous soon enough
Quote:
Originally Posted by vrk View Post
mAx,
Thank you very much for your reply. When i try to export the mesh in Gambit, it is giving me the warning sign "Volume. 1 is not meshed and is not exported". Also boundary conditions on Face. 1(velocity Inlet) and Face. 4 (Outflow) are not exported. Also in "Fluent-Boundary conditions", I can't see velocity Inlet and outflow b.c's. Please see Fig. 1 for the warning sign given by Gambit in Transcript window. In Fig. 2, I assigned the velocity inlet and out flow B.C.'s on both virtual faces (rectangular and quarter circle). I am not sure if this is the right procedure or not?
Is there any other way to mesh the geometry without creating virtual volumes and also i need to have a finer and smoother mesh near wall boundaries?

Thanks
Ravi
It doesn't make any difference if you export a real or virtual meshed-volume.
In your case you need to know why the volume isn t exported.
For sure Gambit gives you some info while you attempt to mesh it
__________________
In memory of my friend Hervé: CFD engineer & freerider
-mAx- is offline   Reply With Quote

Old   February 8, 2013, 16:45
Default
  #9
vrk
New Member
 
Ravi
Join Date: Dec 2012
Posts: 5
Rep Power: 4
vrk is on a distinguished road
Far,

Could you please tell me how you meshed the 3-D falt tube geometry in ICEM CFD?I am new to this software as i started using it very recently. I really appreciate if you could tell how you did meshing in ICEM.

Thank you.
Regards,
Ravi
vrk is offline   Reply With Quote

Old   February 9, 2013, 04:57
Default
  #10
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,946
Blog Entries: 6
Rep Power: 39
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Hey it was really simple. Did you check the files?
Far is offline   Reply With Quote

Old   February 17, 2013, 19:10
Default
  #11
vrk
New Member
 
Ravi
Join Date: Dec 2012
Posts: 5
Rep Power: 4
vrk is on a distinguished road
Far,

I tried to mesh the Flat tube geometry in ICEM CFD. But, I am unable to specify nodes along the z-direction edges.Can you tell me where i am doing wrong.

Thanks for your help.

Ravi
Attached Images
File Type: jpg Flat tube mesh problem.jpg (94.0 KB, 9 views)
Attached Files
File Type: zip Flat tube ICEM CFD.zip (12.9 KB, 2 views)
vrk is offline   Reply With Quote

Old   February 18, 2013, 13:49
Default
  #12
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,946
Blog Entries: 6
Rep Power: 39
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Please see this ...
Attached Files
File Type: zip Flat tube ICEM CFD.zip (12.5 KB, 11 views)
Far is offline   Reply With Quote

Old   August 26, 2014, 03:04
Default Mesh not written and is not exported
  #13
New Member
 
Aalisha
Join Date: Jan 2014
Posts: 18
Rep Power: 3
aalisha is on a distinguished road
Quote:
Originally Posted by vrk View Post
mAx,
Thank you very much for your reply. When i try to export the mesh in Gambit, it is giving me the warning sign "Volume. 1 is not meshed and is not exported". Also boundary conditions on Face. 1(velocity Inlet) and Face. 4 (Outflow) are not exported. Also in "Fluent-Boundary conditions", I can't see velocity Inlet and outflow b.c's. Please see Fig. 1 for the warning sign given by Gambit in Transcript window. In Fig. 2, I assigned the velocity inlet and out flow B.C.'s on both virtual faces (rectangular and quarter circle). I am not sure if this is the right procedure or not?
Is there any other way to mesh the geometry without creating virtual volumes and also i need to have a finer and smoother mesh near wall boundaries?

Thanks
Ravi
Hey Ravi,

I know its a very old post but I am also struggling with something similar. I am working on a straight blade collapsible turbine. while generating the mesh I also get this error of mesh not written on face (interface between the stator and rotor) and is not exported. Do you know why this error is occurring again and again? If you can suggest it will be a great help.

Thanks-
Aalisha
aalisha is offline   Reply With Quote

Reply

Tags
flat tubes, radiator

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Meshing & Geometry - issue with inner hollow tube rendering kavanaa1 FLOW-3D 1 November 27, 2012 17:02
[ANSYS Meshing] Unwanted bias while meshing a tube with sweep and inflation rasko ANSYS Meshing & Geometry 7 July 23, 2012 10:31
[ANSYS Meshing] Meshing for flat plate immersed solid hamed.majeed ANSYS Meshing & Geometry 0 July 10, 2012 13:32
[ANSYS Meshing] Meshing of tube bundle hassaan ANSYS Meshing & Geometry 1 June 28, 2011 13:42
Meshing strategy for a tapered tube Dave FLUENT 0 January 4, 2006 14:20


All times are GMT -4. The time now is 04:02.