[ICEM] Equal Spacing on all the edges

 Register Blogs Members List Search Today's Posts Mark Forums Read

 March 13, 2013, 16:54 Equal Spacing on all the edges #1 Member   Tarantino Join Date: Feb 2013 Posts: 34 Rep Power: 4 Hi ! I work with the geometry which including so many blocks. I want to know how can I define an equal spacing for the whole edges, so ICEM decide how many nodes should assign to have the spacing? For instance, I have two blocks with two difference edge length. for the first I should assign 20 nodes to achieve spacing 0.1 and for the next I should assign 10 node to have 0.1 spacing. Is it possible that I just assign 0.1 as spacing and not Number of nodes? or is it possible to equalized the spacing in different blocks? In ICEM Pre-Mesh Parameters > Mesh Parameters ones can set number of the nodes and not spacing. I try Match Edges, but it is not working for this purpose! thanks asal likes this.

 March 13, 2013, 20:56 #2 Senior Member   Stuart Buckingham Join Date: May 2010 Location: United Kingdom Posts: 267 Rep Power: 16 Tarantino, ICEM does not work like that. For instance, what spacing would you have if you had parallel edges on one block with different lengths? If your geometry is purely orthogonal, then the method you described would work, however 99.99% of geometries do not contain purely orthogonal parts, and so specifying the number of nodes is the most reliable way. Stu asal likes this. __________________ http://bc247.wordpress.com

 March 14, 2013, 09:15 #3 Senior Member     Simon Pereira Join Date: Mar 2009 Location: Ann Arbor, MI Posts: 2,662 Blog Entries: 1 Rep Power: 35 Actually, what I would do, at least to start, is specify 0.1 on the geometry (Mesh tab => Part size setup or something like that). Then when my blocking topology is mostly laid out, I go to blocking => Premesh Params => Update Sizes... This seeds my blocking based on the sizes. But you would end up with that size being a max size. So the count would be set on the shortest edge and would propagate to all the parallel edges... Stu is right about that being the way things work... asal likes this. __________________ ----------------------------------------- Please help guide development at ANSYS by filling in these surveys Public ANSYS ICEM CFD Users Survey This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)... CFD Online Users Survey

 March 15, 2013, 10:35 #4 Senior Member   Astio Lamar Join Date: May 2012 Location: Pipe Posts: 154 Rep Power: 5 This is great. I have also the same issue, but it is work now! Is it possible to define a default ratio and spacing 1, spacing 2 for the whole blocks also? For instance the default ration is 2, but I want to assign 1.2 far all edges. Can I do that? Also I want to know more about Space Relative, Copy absolute, Linked bunching as well as Match Edge option. I try Match Edge, but I cannot work with it! Thanks in advance for your reply.

 March 15, 2013, 10:47 #5 Senior Member     Simon Pereira Join Date: Mar 2009 Location: Ann Arbor, MI Posts: 2,662 Blog Entries: 1 Rep Power: 35 Sure, You can adjust the default bunching ratio. Look under Settings => Meshing Options => Hexa Meshing Options. You can't setup a default for the initial spacing because that is much more model sizing and edge length dependent. As for Copying edge distributions, "relative" means relative to the edge length. Absolute means match the actual initial height measurement. Linked bunching is tricky until you realize that you just need to select the lower end of each set... Turn on bunching and notice the arrows... For the linked bunching, you want to select the edges at the base of the arrow. This should be well explained in the help. Matching the end spacing is pretty easy. You select the sorce edge and the target edge(s) and it takes the end spacing from the one and copies it to the others... If you use the automatic method, you can't pick which is the source, so there are some options in there to chose if you keep the smallest, average or largest end spacing... asal likes this. __________________ ----------------------------------------- Please help guide development at ANSYS by filling in these surveys Public ANSYS ICEM CFD Users Survey This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)... CFD Online Users Survey

 March 15, 2013, 13:00 #6 Senior Member   Astio Lamar Join Date: May 2012 Location: Pipe Posts: 154 Rep Power: 5 thanks for your reply. just one more question. Is it possible to know the number of elements before convert the unstruct mesh? after it we can see it in mesh info.

 March 15, 2013, 14:13 #7 Senior Member     Simon Pereira Join Date: Mar 2009 Location: Ann Arbor, MI Posts: 2,662 Blog Entries: 1 Rep Power: 35 Yes, right click on Pre-mesh in the blocking branch of the tree and select "pre-mesh info". asal and FJSJ like this. __________________ ----------------------------------------- Please help guide development at ANSYS by filling in these surveys Public ANSYS ICEM CFD Users Survey This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)... CFD Online Users Survey

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post vishwa OpenFOAM Native Meshers: snappyHexMesh and Others 23 August 6, 2014 03:50 bobburnquist OpenFOAM Native Meshers: snappyHexMesh and Others 2 November 25, 2012 09:54 sc298 OpenFOAM Native Meshers: snappyHexMesh and Others 2 March 27, 2011 21:11 Tobi OpenFOAM Native Meshers: snappyHexMesh and Others 0 November 10, 2010 04:23 chelvistero OpenFOAM 11 January 15, 2010 20:43

All times are GMT -4. The time now is 11:17.