CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] Prisms Intersection

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree6Likes
  • 1 Post By sandeep_tu
  • 1 Post By Far
  • 1 Post By kad
  • 1 Post By diamondx
  • 2 Post By PSYMN

Reply
 
LinkBack Thread Tools Display Modes
Old   March 18, 2013, 10:51
Default Prisms Intersection
  #1
New Member
 
Sandeep
Join Date: Apr 2009
Location: Munich, Germany
Posts: 29
Rep Power: 7
sandeep_tu is on a distinguished road
Dear All,

I have got a problem while generating prisms (intersecting prisms), please see attached figure.
How can I overcome this problem (like Shrinkage or ignoring prisms there)? Any suggestions or tips could be helpful for me.

Thank you
Sandeep
Attached Images
File Type: jpg seat+driver.JPG (87.1 KB, 29 views)
Far likes this.
sandeep_tu is offline   Reply With Quote

Old   March 18, 2013, 11:01
Default
  #2
Super Moderator
 
diamondx's Avatar
 
Ghazlani M. Ali
Join Date: May 2011
Location: Canada
Posts: 1,218
Blog Entries: 23
Rep Power: 18
diamondx will become famous soon enough
Send a message via MSN to diamondx
you need to use "define thin cut" and select the two surfaces intersects. that's a very sharp angle there, not sure if that feature can help tough...
__________________
Regards,
New to ICEM CFD, try this document --> http://goo.gl/G2gkE
Ali
diamondx is offline   Reply With Quote

Old   March 19, 2013, 04:19
Default
  #3
New Member
 
Sandeep
Join Date: Apr 2009
Location: Munich, Germany
Posts: 29
Rep Power: 7
sandeep_tu is on a distinguished road
I tried with specifing "thin cut" surfaces unfortunately it didnīt help.

Any suggestions how to apply shrinkage or ignoring prisms there (Ex: see attachment)

Regards
Sandeep
Attached Images
File Type: jpg mesh shrink.jpg (24.0 KB, 20 views)
sandeep_tu is offline   Reply With Quote

Old   March 19, 2013, 09:43
Default
  #4
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,899
Blog Entries: 6
Rep Power: 37
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Try Tgrid. There is more control on prisms behaviour
PSYMN likes this.
Far is offline   Reply With Quote

Old   March 19, 2013, 10:54
Default
  #5
kad
Senior Member
 
Join Date: Feb 2013
Location: Germany
Posts: 152
Rep Power: 12
kad will become famous soon enoughkad will become famous soon enough
You could try one of the following steps:
- set prism height "0" for floating height in problematic regions
- make use of the auto-reduction function which can be found under advanced prism settings.
- I would rather go back to geometry and just close the critical gaps if your geometry does not have to be 100% accurate
PSYMN likes this.
kad is offline   Reply With Quote

Old   March 19, 2013, 11:17
Default
  #6
Super Moderator
 
diamondx's Avatar
 
Ghazlani M. Ali
Join Date: May 2011
Location: Canada
Posts: 1,218
Blog Entries: 23
Rep Power: 18
diamondx will become famous soon enough
Send a message via MSN to diamondx
use simon's tips and trick to find a solution for your problem. worst come to worst, you will need to evaluate the importance of that region (remove the sharp angle if you don't need information there):

https://docs.google.com/file/d/0ByIL...BQT3pQMjQ/edit
PSYMN likes this.
__________________
Regards,
New to ICEM CFD, try this document --> http://goo.gl/G2gkE
Ali
diamondx is offline   Reply With Quote

Old   March 19, 2013, 22:09
Default
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,650
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
I was asked by two people to come and comment here, but I think the right things have already been said.

1) refining the mesh size, setting the initial height to 0 (float) and turning on options like "auto reduction" should help.

2) If that fails, then altering the geometry so you don't have such a tight space will help. I have worked on actual industry examples and they usually place a box behind the body (intersecting the body and the seat). In real life the driver wouldn't be leaning forward from the seat anyway, closing off much of that gap will not hurt your accuracy, but it will make the meshing/solving easier.

3) If all else fails and you are interested in trying TGrid Meshing, TGrid Tetra really has advanced over the past few years and its "auto reduction" and handling of situations like this is really superior... Of course, it has its own learning curve, so it may not be for everyone.
Far and cfd seeker like this.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
intersection of meshes in centrifugal pump eng_norouzi CFX 0 October 4, 2011 03:45
[GAMBIT] 3D mesh for pipe intersection pranab_jha ANSYS Meshing & Geometry 3 May 28, 2010 01:33
Polyline at intersection of two planes Francesco CFX 2 July 29, 2009 08:03
intersection of two cubes. park Main CFD Forum 2 July 1, 2009 03:19
meshing at a pipe intersection cyn FLUENT 0 December 20, 2006 02:16


All times are GMT -4. The time now is 12:09.