|
[Sponsors] |
March 28, 2013, 03:46 |
improve quality in 3d wing
|
#1 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Hi guys,
I wonder how I can improve the elements near the trailing edge in the attached photos of a profile is not symmetric. I've thought about moving the rear vertical edge forward to avoid sharp angles ... |
|
March 28, 2013, 06:48 |
|
#3 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Thanks Far. It is the same strategy as in this video:
http://www.youtube.com/watch?v=EknKVAJGEJ8 but why do not you collapse the blocks on your video? http://www.youtube.com/watch?v=mgjRT4WY_iA you have a sharp edge too... it's because it is a symmetrical profile? |
|
March 28, 2013, 07:36 |
|
#4 |
Super Moderator
|
If take a look at thread http://www.cfd-online.com/Forums/ans...mesh-wing.html you will notice there are four methods of dealing wing meshing. So in video it is one the methods described in above thread. If wing is not too sharp, you can continue with your present method.
|
|
March 28, 2013, 11:35 |
|
#5 |
Senior Member
Ali
Join Date: Jan 2012
Location: Pakistan
Posts: 134
Rep Power: 16 |
Is block collapsing possible in multizone meshing? AS the quality on the wing with sharp TE is very low nearly 0.0.
__________________
Best Regards Ali |
|
March 28, 2013, 16:37 |
|
#7 |
Senior Member
Ali
Join Date: Jan 2012
Location: Pakistan
Posts: 134
Rep Power: 16 |
__________________
Best Regards Ali |
|
April 10, 2013, 04:55 |
Extrude features
|
#8 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Hi again,
I've been taking a look at the following thread, Hexa Structured Mesh on Wing, and I've seen the 4 meshing methods. For a profile with sharp trailing edge is better collapse blocks. For that reason, I tried that approach previously with the same example I īve written in post # 1 but I got errros. Therefore I would like to clarify some doubts. 1š - In this thread, Hexa Structured Mesh on Wing, Hybrid said you could extrude a face from a 2D block (# 11), however, I think you can only extrude block faces from 2D and not from 3D. Then, Simon said that to do this you have to use "Convert 2D to 3D", which I think is more correct. Once done, if you could use "Extrude Face"... itīs possible. 2š- In image 1 presents the domain. I want to mesh this section and them I want to extrude along the domain. So I think a block 2D planar. This always appears in the middle section of the domain. If this block transfer 2d to the final section (image 2) and active ORFN why I see bend blocks, I`ve tried to compare it with the FAR videos but do not understand why I get bent blocks (image 3). Itīs like the first reference in this blocks or something similar? |
|
April 10, 2013, 05:01 |
|
#9 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
3š- If you want to do the mesht in the middle section and then to convert 2D to 3D to one side (image 1) and then extruded to the other side (image 2) works. Then merge blocks and I got this (image 3). However, if deselected "whole blocks" appear again as if they were separate (image 4) . Anyone know why?
|
|
April 11, 2013, 04:51 |
|
#10 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Iīve got the mesh. I have done that blocks from 2D Planar blocking and using Convert 2D to 3D and Extrude Faces. The worst determinant 3x3x3 is 0.5, min quality is 0.5, min angle is 40.5 and the max value of vol. change is 6.
I know that way is more work but I wanted to check this way and associate doubts. For that reason, if you could comment the last 2 post Iīll be grateful. I would know, why concluded Far that the best flow domain is hemisphere in L.E. and rectangular at outlet (#29 Structured Hexa Mesh on Wing). For other hand, Itīs recommended disassociate from geometry when you extrude a block and then associate again? |
|
April 15, 2013, 03:20 |
|
#11 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
can you tell me something about these questions, please!
|
|
April 18, 2013, 03:18 |
|
#12 |
Super Moderator
|
In fact when I said the hemisphere domain is best was due to fact that the leading edge is circular and mesh would have the less distortion. But you can use rectangular domain at inlet as I have shown it many times.
Same goes for trailing edge. But one must be careful if trailing is too sharp, in this case you need to collapse blocks and mesh lines becomes parallel to airfoil chord. so if you rounded domain at outlet then you will have high distortion at outlet boundary when straight mesh lines will meet round boundary. As far as extrude method is concerned, it is generally not recommend for entire model. You can few portions blocked with this method if deemed necassary otherwise always use top-down approach as it saves you alot time and which is basic advantage of ICEM. It saves you huge amount of time on complex models due to top-down approach. |
|
April 18, 2013, 03:48 |
|
#13 | |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Thank you for your answer.
Are very helpful to me. But Iīm still wondering about one... the second one (2š). I not finish to understand it. I donīt know if you can understand it what I ask. I looked your video "Sphere cube meshing : Part I - ICEM CFD 14.0 Basics" for explain about VORFN blocks but at the end I couldnīt find my doubt. For other hand, Iīm dealing with this problem Quote:
|
||
April 18, 2013, 04:21 |
|
#15 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Sure.
Ok. I have a domain like the picture 1. Itīs a 3D domain. Now.. (lf I would like to do this domain with an extrude) I do a 2D planar blocking and this 2D planar block appears in the middle of the domain. So.. like I want to do an extrude I associate edge to curve (the 4 edges, I said this cos in the picture Iīve only put 3 arrows) and now the edge are in one side of the domain (this way I can do the extrude more easily) (picture 2). And now, Iīm wondering... if I turn on VORFN part.. I can see them (VORFN blcoks) but.... they are refered to the initial place, I mean, in the center of the domain (picture 3). why? Why do they go to the same side that I īve associated them before? |
|
April 18, 2013, 04:34 |
|
#16 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
I have to say that I got the mesh. This method worked.
But, I would like to say something about associate edge when someone make an extrude too. I had to disassociate the edges and them re-associate them. is it recommendable to do this when you use an extrude? This was my result. for better visualization here the project files: https://www.dropbox.com/s/rhlwsvxnmq5swpg/Project1.rar |
|
April 18, 2013, 04:37 |
|
#17 | |
Super Moderator
|
Quote:
Generally speaking VORFN blocks are not important and work internally as designed and are always there. Their internal working is not discussed anywhere. But I showed something how they behave in some situations. |
||
April 18, 2013, 09:06 |
|
#18 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
Ok. Understood. I just want to know why this behaviour.
Thanks equally! |
|
April 19, 2013, 03:25 |
|
#20 |
Senior Member
Javi
Join Date: Jan 2013
Posts: 276
Rep Power: 16 |
When I said behaviour I want to say the same in post #15. But youīre right.. itīs an internal working. Thanks for youtubeīs videos about this topic :-)
|
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
[ICEM] how to improve mesh quality around sharp edge? | foolboy007 | ANSYS Meshing & Geometry | 1 | January 23, 2013 11:57 |
[ICEM] how to improve mesh quality in the hydrocyclone | veerukvb | ANSYS Meshing & Geometry | 2 | October 29, 2012 05:14 |
[ICEM] how to improve mesh quality in the hydrocyclone | veerukvb | ANSYS Meshing & Geometry | 2 | October 23, 2012 20:28 |
Improve Mesh quality - airfoil simulation | Lukas84 | STAR-CCM+ | 4 | July 6, 2010 10:07 |
Improve smoothness & quality of structured grid | quarkz | Main CFD Forum | 2 | March 10, 2007 15:26 |