CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] A mesh generation for aero acoustic computation

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 15, 2010, 23:27
Default A mesh generation for aero acoustic computation
  #1
Member
 
Join Date: Dec 2009
Location: China
Posts: 79
Rep Power: 7
ringtail is on a distinguished road
Hi everyone,
The following picture shows a mesh of a 2D cylinder. This mesh is mentioned in the document "Tutorial: Modeling Flow-Induced (Aeroacoustic) Noise Problems Using FLUENT".


1.JPG

2.JPG

Who can tell me how to generate a similar one or where to download the mesh file cylinder2d.msh

Wish your repies.

thanks very much.
ringtail is offline   Reply With Quote

Old   April 15, 2010, 06:54
Default
  #2
New Member
 
Mark Bell
Join Date: Apr 2010
Location: Holywood
Posts: 12
Rep Power: 7
mbell10 is on a distinguished road
The mesh has been formed by creating a cell density region behind the cylinder. Here the cells are clumped together and allowed to expand at a particular rate. Its relatively straight forward in Icem
mbell10 is offline   Reply With Quote

Old   April 15, 2010, 11:27
Default
  #3
Member
 
Join Date: Dec 2009
Location: China
Posts: 79
Rep Power: 7
ringtail is on a distinguished road
Quote:
Originally Posted by mbell10 View Post
The mesh has been formed by creating a cell density region behind the cylinder. Here the cells are clumped together and allowed to expand at a particular rate. Its relatively straight forward in Icem
dear Mark Bell

thanks for your reply. But, I do not quite catch your meaning, what does " Its relatively straight forward in Icem" mean?
Is there direct command for cell density in ICEM? what is it?

thanks again.
ringtail is offline   Reply With Quote

Old   April 16, 2010, 05:45
Default
  #4
New Member
 
Mark Bell
Join Date: Apr 2010
Location: Holywood
Posts: 12
Rep Power: 7
mbell10 is on a distinguished road
Under the Mesh tab, there is a button, "Create Mesh Density".

It will allow you to create your regions of mesh density and control how dense the mesh is. It will take a little playing about with, but otherwise it's quite straight forward.
mbell10 is offline   Reply With Quote

Old   April 16, 2010, 12:13
Default
  #5
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
ICEM CFD's create mesh density doesn't apply to Patch dependent 2D meshes, so make sure you have your surface mesh method set to "Patch Independent".

Simon
PSYMN is offline   Reply With Quote

Old   April 17, 2010, 03:24
Default
  #6
Member
 
Join Date: Dec 2009
Location: China
Posts: 79
Rep Power: 7
ringtail is on a distinguished road
hi, Mark Bell and simon
i have read ICEM CFD help manual carefully. And now I know density box
"affects only Tetra, Cartesian, and Patch Independent surface mesh methods."

I tried to generate the mesh by HEXA MESHER, and then created a mesh density, and it did not work.

Is hexa mesh a cartesian mesh?
ringtail is offline   Reply With Quote

Old   April 17, 2010, 13:18
Default
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Nope, these are all different methods... What matters is how the mesh is generated. The methods that work with the Density boxes all rely on top down meshing with a back ground grid... On the other hand, Hexa relies on a blocking structure that lets you mesh it any way you like... You can refine blocks in hexa or use blocking strategies (such as Ogrid) to refine the mesh...

The method closest to what you had seen in Gambit is the Patch Independent surface meshing with "quad" or "quad dominant". This method will accept density zones or sizing function in the same way (and for the same reasons) as they worked in Gambit...

Other methods, such as ICEM CFD Hexa, may be able to give a much higher quality mesh, but require a bit more practice and effort due to the higher level of user interaction. Have you tried the ICEM CFD Hexa tutorials?

Simon
PSYMN is offline   Reply With Quote

Old   April 19, 2010, 02:27
Default
  #8
Member
 
Join Date: Dec 2009
Location: China
Posts: 79
Rep Power: 7
ringtail is on a distinguished road
Quote:
Originally Posted by PSYMN View Post
Nope, these are all different methods... What matters is how the mesh is generated. The methods that work with the Density boxes all rely on top down meshing with a back ground grid... On the other hand, Hexa relies on a blocking structure that lets you mesh it any way you like... You can refine blocks in hexa or use blocking strategies (such as Ogrid) to refine the mesh...

The method closest to what you had seen in Gambit is the Patch Independent surface meshing with "quad" or "quad dominant". This method will accept density zones or sizing function in the same way (and for the same reasons) as they worked in Gambit...

Other methods, such as ICEM CFD Hexa, may be able to give a much higher quality mesh, but require a bit more practice and effort due to the higher level of user interaction. Have you tried the ICEM CFD Hexa tutorials?

Simon
hi, Simon
yes ,i have.
as the below images show, I have generated the by using O-grid. The mesh quality seems good.
1.jpg

2.jpg

3.jpg

In fact, my real trouble is how to refine or coarsen the mesh. In order to make suer the y plus is approximate to 1, I have to make the first layer grid be close to cylinder wall enough. So the density of radial grid should be big. And for making sure aspect ratio do not exceed limitation of FLUENT, I have refined the density of circumferential grid too. as a result, the mesh became very very dense.( up to 3 million nodes.)

how could I coarsen the mesh ?

thanks.
ringtail is offline   Reply With Quote

Old   June 8, 2010, 19:49
Default
  #9
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
This is a bit late (I don't always have time to get back to CFD online threads), but hopefully you figured out how to adjust the edge params to have fewer parameters but the same intial distribution. You could even split that Ogrid so you could have two separate ratios.

I would probably have blocked it a bit differently, with HGrid thru the entire domain and then splits ahead and behind the hole, and above and below the circle. This would give 9 Hgrid blocks, the middle one would be centered on the circle. Then I would create an Ogrid in that center block, delete its center o grid and associate its center square with the circle... This will give higher quality than this current example and the mesh density would be easier to control.
PSYMN is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] Generating Mesh for STL Car in Windtunnel Simulation tommymoose ANSYS Meshing & Geometry 48 April 15, 2013 04:24
Mesh generation software is needed H.Dou Main CFD Forum 12 May 4, 2011 15:20
ICEM - incomplete mesh generation ralph CFX 0 June 23, 2008 23:35
Convergence moving mesh lr103476 OpenFOAM Running, Solving & CFD 30 November 19, 2007 15:09
3-d elliptic generation mesh Gang Sun Main CFD Forum 5 September 16, 1998 00:24


All times are GMT -4. The time now is 14:22.