CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] Simple Meshing (w/o blocking)

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   May 10, 2010, 16:50
Default Simple Meshing (w/o blocking)
  #1
New Member
 
Join Date: Apr 2010
Posts: 17
Rep Power: 7
shohin is on a distinguished road
Hi all,

i am struggling with some very simple operations in ICEM which are easily done with my "old" software ADINA-F

At the moment i just want to make some very simple model: a 2D parallel plate.
I easily managed to define points (4), curves (4) and a surface (1), and defined the bocos using different parts (3) for FLUENT - so far so good.

Now, i just want to have 10 subdivision on 2 curves (inlet and outlet) and
100 subdivisions on the other 2 curves (walls). Furthermore i want to apply some bias for having a finer mesh near the boundary walls. Nothing really complicated, i thought!

First, I tried using the mesh curve function and second i tried to mesh the surface itself, but which way i have chosen, i never got the desired spacing and number of elements (10*100 = 1000!).

Can the task be accomplished w/o using this ("strange", sorry) blocking stuff??!


Thanks a lot for your answers and also for all the informations available in this great community!!

best
shohin
shohin is offline   Reply With Quote

Old   May 10, 2010, 21:10
Default
  #2
New Member
 
Brian Polly
Join Date: Feb 2010
Posts: 26
Rep Power: 7
Brian_P is on a distinguished road
I am no expert, but I think you are better off 2d blocking. Associate edges to curves then blocking>premesh param> there is a edge function where you can specify # nodes per edge.

Hope this helps
Brian_P is offline   Reply With Quote

Old   May 11, 2010, 11:37
Default
  #3
New Member
 
Join Date: Apr 2010
Posts: 17
Rep Power: 7
shohin is on a distinguished road
HI,

thanks for your answer.

Does this mean i have to create a block first and then use the functions
you mentioned?

I will give it a try, although i do not understand why such a simple action is so
complicated...
shohin is offline   Reply With Quote

Old   May 22, 2010, 06:59
Default
  #4
New Member
 
Join Date: Apr 2010
Posts: 17
Rep Power: 7
shohin is on a distinguished road
hi,

so i tried the method proposed by Brain_P, but it is still not satisfiying.
I also have no idea which meshing method i should use (ok, no delauney,but..?)

It would be very very kind if someone could give me a small step_by_step "tutorial" of how to generate a simple 2D parallel plate with a structured mesh (finer resolution at the boundaries) (for use in Fluent). Lets say i have the points, lines and defined the bocos already. Do i need a surface?

Alternatively i thought about importing the STL file of the mesh into ICEM, but afterwards i have to delete the mesh for defining the bocos. So i would face the same problem...

thanks a lot for your help...

best
shohin
shohin is offline   Reply With Quote

Old   May 22, 2010, 13:46
Default
  #5
New Member
 
Join Date: Mar 2010
Posts: 5
Rep Power: 7
vagmakr is on a distinguished road
Hello

First lets make somethink clear.

If you want a structured grid you have to use the blocking technique.


There are some steps

1.Geometry creation or import (so you have curves , vertices , surfaces)

2.2d planar blocking creation

3.At the blocking association menu , associate the blocking edges with the geometry curves (use the edge - curve association button)

4.At the pre-mesh params button in the blocking menu use the edge param button to chose your desired grid resolution

5. Update the mesh and tick the pre - mesh box

That is it nut be aware that you have to chose a proper mesh element size at the global meshing menu and you have to save and output your mesh using the proper output solver.

Hope this helps.
vagmakr is offline   Reply With Quote

Old   May 24, 2010, 10:48
Default Basic steps.
  #6
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
It can also be done with patch dependent meshing (without blocking), but you need to make sure you increase the mapping...

However, I don't think it is any easier to setup mesh sizes on curves than it is on block edges. In fact, block edges are easier because you can copy to parallel.

Also, since the blocking is really structrued mesh, it will produce much better meshes (better mapping interpolation) with less memory, etc. than any other method...

The advantage of blocking over unstructured mapping methods increases with the complexity of the model. Its patch independence also gives it a powerful advantage for poor geometry.

You could use the interactive blocking or the automatic 2D Surface Blocking.

Basic steps for interactive...

1) Create your geometry (4 points, then curves from points, then surface from curves, but actually, you could also create the surface directly from the 4 points) Make sure to put your curves/surface in parts to setup for your Fluent Bocos.

2) Go to the blocking tab, initialize blocking => 2D planar. Don't select anything else, just hit apply. This will create a block that matches your surface.

3) Associate the edges with he curves... For this simple geom, you could use the automatic associate button to take care of this in one click. For more interesting models, you may want to associate interactively.

4) Set up your edge params (this is the same as setting up curve distributions, except more powerful and not constrained to curve segments)

5) Generate premesh, then convert to unstructrued mesh, then output to Fluent.


Basic Steps for automatic method...

1) Setup the geometry and sizes as you had before.

2) Initialize Blocking => 2D Surface Blocking. Hit apply with all defaults. This will mesh a full Car body as easily as it handles your simple square.

3) Turn on the premesh. It may be ready to go or you may want to adjust some edge distributions.

4) When satisfied, convert premesh to unstructured mesh (right click option under premesh), then output to Fluent.


Blocking is not as "Strange" as it may first appear. The separate "blocking" is just a way of separating the mesh topology from the geometry topology, which is a very powerful advantage.
PSYMN is offline   Reply With Quote

Old   May 24, 2010, 10:50
Default online?
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Have you seen the tutorial for the 2D airfoil on www.youtube.com/ansysinc/

Your model would be much much simpler, but this does cover all the steps in a more visual way.

If you have access to the customer portal (or built in tutorials right inside your software) you could check out the 2D pipe junction or the 2D car tutorials.
PSYMN is offline   Reply With Quote

Old   May 25, 2010, 04:23
Default
  #8
New Member
 
Join Date: Apr 2010
Posts: 17
Rep Power: 7
shohin is on a distinguished road
Dear PSYMN, dear vagmakr,

thanks a lot for your help...finally, i am able to generate exactly what i want.
And as always, if you know how to do it, everything seems logic and clear, nothing "strange" about!!

I used the interactive guide from PSYMN and everything was fine....

Again, thanks to you guys and to this really nice forum...

best
shohin
shohin is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Simple Frustrating Meshing Issue in Gambit (w/pics) Dylan ANSYS Meshing & Geometry 6 March 23, 2009 17:14
Meshing on simple geometry pukiwawa FLUENT 5 August 31, 2008 12:04
Meshing An airfoil with a simple plain flap S. Kalam FLUENT 7 January 30, 2005 21:22
Singularity of grid?Volume meshing vs face meshing Ken Main CFD Forum 0 September 4, 2003 11:09
Simple Meshing Problem with Gambit Mario FLUENT 4 April 18, 2003 09:52


All times are GMT -4. The time now is 17:47.