CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ANSYS Meshing] Icem cfd - hexa meshing

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By PSYMN

Reply
 
LinkBack Thread Tools Display Modes
Old   July 14, 2011, 06:03
Default Icem cfd - hexa meshing
  #1
New Member
 
Arunkumar N D
Join Date: Dec 2010
Posts: 9
Rep Power: 6
arunkumarnd is on a distinguished road
i am trying to mesh a torpedo kind of geometry the problem comes when i create pre- Mesh, some negative mesh generating at the area of fin. how can i get rid of it???...

The pictures shows where the problem
Attached Images
File Type: jpg 3.jpg (91.7 KB, 145 views)
File Type: jpg 1.jpg (78.3 KB, 146 views)
File Type: jpg 2.jpg (61.3 KB, 132 views)
arunkumarnd is offline   Reply With Quote

Old   July 14, 2011, 12:12
Default Aspect ratio...
  #2
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
That mesh has poor aspect ratio...

The solution is with adjusting the edge parameters behind the torpedo... Ideally, you would match edges (edge distributions) behind the torpedo to match the edge distribution of the trailing edge.

A bigger quality problem is at the nose of your torpedo where you have wide open (high max angle) quads. You can sort this out with an Ogrid topology.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   July 14, 2011, 12:30
Default
  #3
New Member
 
Arunkumar N D
Join Date: Dec 2010
Posts: 9
Rep Power: 6
arunkumarnd is on a distinguished road
i cleared the nose problem, the tailing edge of the torpedo is just touching the end circle so its hard to match the edges, if i increase the length of the torpedo at the end it may work na ???
arunkumarnd is offline   Reply With Quote

Old   July 14, 2011, 14:07
Default
  #4
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Just click on the edge behind the torpedo and match it to the edge at the back of the torpedo... You can even do this at the far field if you like... Once that aspect ratio is reduced, quality will appear better.

Assuming that those elements were highlighted by the aspect ratio metric...

I would have to see a zoom in on the problem cells, maybe even a scan plane thru the area, to make a better suggestion.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   July 18, 2011, 08:21
Default initial impressions...
  #5
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Taking a closer look at your actual model, I see that your fins have sharp trailing edges. This means you need to collapse the blocks behind these edges... (under Merge Vertices, you can learn more about it with the pipe fin example or the airfoil example up on youtube) You will then need to collapse the blocks beside those collapsed blocks all the way out to the far field extents.

I also suggest you put this block inside an ogrid...

Actually, I suggest working on a quarter of the model an using a quarter ogrid...

I will make a quick go at it later...
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   July 18, 2011, 09:10
Default
  #6
New Member
 
Arunkumar N D
Join Date: Dec 2010
Posts: 9
Rep Power: 6
arunkumarnd is on a distinguished road
Actually i tried that method to collapse blocks,but i have a confusion regarding which edges i have to select when doing it , for a trail i randomly selected different edges but didn't get the right collapse ..i will try that again. pipe fin example is available in you tube???

The procedure i followed for making o grid is difine the blocks which we have to remove as 'dead' then make o grid around it ..is that the right way ?
arunkumarnd is offline   Reply With Quote

Old   July 18, 2011, 21:57
Default Done...
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
For collapse blocks, you select the direction to collapse... This is the edge you want to go away... And then you select all the blocks you want to collapse in that direction.

I did if for you and sent a replay file...

Here are some images for everyone else... (I just did a quick blocking without spending much time on matching edges, etc.)

I used a quarter ogrid to wrap the torpedo and I used collapse to capture the sharp trailing edge on the fins...
Torpedo.jpg

Then I put a final quarter Ogrid in the wake of the torpedo
Torpedo2.jpg

Pretty quick to do with ICEM CFD... If I spent more time, i would match edges, etc for smooth transitions between the sections...

This would make a nice little demo if I could use the file publically.
lth likes this.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   July 19, 2011, 10:00
Default As often happens...
  #8
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
As often happens, your first try at a particular topology (such as a torpedo) is not really your best. As soon as you look back on it, you can think of a better topology.

If I did this one again, I would not have the fins extend to the edge of the original OGrid... I would split that ogrid so the fins fell within it... That would probably help with convergence around the tips of the fins... In ICEM CFD, the extra effort would be a single split operation (across the Ogrid) to capture both fins...
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   July 19, 2011, 11:34
Default
  #9
New Member
 
Arunkumar N D
Join Date: Dec 2010
Posts: 9
Rep Power: 6
arunkumarnd is on a distinguished road
it was really helpful all your advice , and thanks a lot for all the effort you taken during your busy schedule.. i am not that expert just learning things and i come to know experience is the only on thing that make u master of ICEM , every day i learning some thing different ... the mesh is so good as it is, if we know how to do O grding effectively we can improvise in many area na ?

once again i am thanking you... i learned so many things from you iam hoping help from you in future also

Thankfully

Arun
arunkumarnd is offline   Reply With Quote

Old   April 12, 2012, 05:47
Default
  #10
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,915
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Great info by Simon.
Far is online now   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ANSYS Meshing] Workbench 13: Structured Hexa Meshes rooftop ANSYS Meshing & Geometry 18 May 13, 2014 03:57
Learn ANSYS ICEM CFD easy_astronaut ANSYS 2 December 15, 2013 16:34
inflation layers for hexa mesh using icem cfd Apple CFX 4 January 6, 2012 01:12
[ICEM] (ICEM CFD) meshing over a cylinder vmlxb6 ANSYS Meshing & Geometry 6 August 11, 2010 14:37
which of them is better? saha2122 ANSYS Meshing & Geometry 5 June 18, 2010 06:35


All times are GMT -4. The time now is 10:51.