CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] Can I subtract volumes like I could do on Gambit?

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   November 25, 2011, 16:10
Question Can I subtract volumes like I could do on Gambit?
  #1
New Member
 
Kora
Join Date: Nov 2011
Posts: 11
Rep Power: 4
Aoki is on a distinguished road
Hello. Recently my University stopped buying the gambit licence and now we're on ICEM. Now I'm trying to build a geometry for meshing in ICEM, and I'm trying to create a wind-tunnel-like environment, with a wing in it.

If I were on gambit, I would create a volume for the wing, and a volume for the wind-tunnel, then subtract the small one from the big one. But I couldn't figure out how to do that on ICEM. I could still create two bodies on ICEM, but it doesn't seem to have a subtract function. Can I actually do the subtraction of volumes in ICEM like I did in gambit? If not, could anyone please suggest a way to build such geometry? Thanks in advance.
Aoki is offline   Reply With Quote

Old   November 26, 2011, 12:34
Wink It not like Gambit
  #2
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,650
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
ICEM CFD doesn't need you to subtract any volumes...

If you have created the two material points, that is enough. It can figure out the rest without needing to subtract solids, etc. This can save you a lot of trouble, particularly with poor geometry.

You will find that you need to shift your way of thinking when you shift tools from Gambit to ICEM CFD. They are very different tools that work with very different processes.

Definitely try some tutorials to get going and don't ever try to do anything "like in Gambit".

Regards,
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   November 26, 2011, 12:47
Default i do not like gambit too
  #3
New Member
 
Join Date: Nov 2009
Posts: 17
Rep Power: 8
skrzatchlewny is on a distinguished road
I would manage with your geometry like that:
1. draw tunnel (surface)
2. draw airfoil (lines)
3. trim tunnel surface using airfoil contours
4. delete cut geometry

or you can follow this tutorial:
http://www.youtube.com/watch?v=tYrbScUH9RE

cheers
skrzatchlewny is offline   Reply With Quote

Old   November 26, 2011, 12:59
Default
  #4
New Member
 
Kora
Join Date: Nov 2011
Posts: 11
Rep Power: 4
Aoki is on a distinguished road
Thanks guys. Your help is very much appreciated.
Aoki is offline   Reply With Quote

Old   October 24, 2012, 06:04
Post volume subtraction
  #5
New Member
 
waqas
Join Date: Oct 2012
Posts: 1
Rep Power: 0
waqas77 is on a distinguished road
hi. i am doing an underwater vessel drag analysis. i am using the symmetry approach to save computational time. i have studied that there is no need to subtract volumes as in Gambit but my question is that the symmetry face of body is attached to the face of the domain and i have to subtract that. so how can i cut that part to keep the body hollow in order to satisfy the symmetry condition. can anyone help??
waqas77 is offline   Reply With Quote

Old   October 24, 2012, 08:39
Default
  #6
Super Moderator
 
diamondx's Avatar
 
Ghazlani M. Ali
Join Date: May 2011
Location: Canada
Posts: 1,216
Blog Entries: 22
Rep Power: 18
diamondx will become famous soon enough
Send a message via MSN to diamondx
share a picture, i can help you with that ...
__________________
Regards,
New to ICEM CFD, try this document --> http://goo.gl/G2gkE
Ali
diamondx is offline   Reply With Quote

Old   October 24, 2012, 08:46
Default
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,650
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
We usually create the box in the right location. It would initially pass thru the vessel. The surface that passes thru the vessel can be renamed "SYMMETRY" or something like that.

You need a nice sharp curve along the symmetry plane, so use the geometry tab to create curves of intersection between the symmetry plane and what ever parts the vessel is made of.

Put a material point in the box between the hull and the far boundary... When you mesh with octree tetra, it will only fill this boundary. When you mesh with hexa blocking, you can decide which boundary to fill.

So strictly speaking, you don't need to delete the part of the ship outside the boundary. However, the way octree works, it will be much faster to generate the mesh if it doesn't need to consider the area outside the box. It is better to delete those surfaces.

In many cases, the geometry will already be a collection of surfs that is well divided. You can just use the geometry tab to delete surfaces/curves and points that are outside your box. You can box select or use other selection tools to make this easy on yourself. If you accidentally delete the wrong surface, you can undo it. Others prefer to create a new part and just add those other surfaces to the new part so they can be careful not to delete the wrong thing. When you are sure you have put all the junk in the JUNK part, you can delete the whole part.

If there are surfaces that past thru the box, you can run "Repair Geometry => Build Diagnostic topology". Among other things, this option will use the symmetry plane intersection curves to automatically cut all the surfaces that it passes thru. Then you can delete the bits outside the box.

In some situations, build topo doesn't split the surface. In that case, you can use the geometry tab => Create/Modify surfaces to segment the surfaces one by one based on a curve or plane... Then delete...
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Problem with Volumes Gambit Danath ANSYS 1 October 19, 2011 08:20
Handling Virtual volumes in Gambit Bharath FLUENT 4 October 30, 2006 20:24
Ghosts Volumes on Gambit ?!! help please Andres D. Ortiz FLUENT 0 October 7, 2001 19:17
Gambit mesh & Negative Volumes Ashutosh FLUENT 5 February 21, 2001 00:59
volumes in gambit christof FLUENT 1 March 9, 2000 17:03


All times are GMT -4. The time now is 21:41.