|February 8, 2012, 22:40||
sub-domain mesh not generated?
Join Date: Sep 2011
Location: United Kigdom
Posts: 51Rep Power: 6
I am sure this has already been asked but I could not find something useful.
On ICEM, I have wind turbine inside a cylindrical volume. I have done the geometry check and build diagnotic topology but sometimes, the blade mesh is not generated, i.e. i only have get a volume mesh without the turbine mesh.
I have noticed that this happens when I try to reduce the 'edge criterion' or/and 'max mesh size' for the blade. For example below 0.02 for edge criterion the blade mesh simply disappears.
Does anyone has any suggestions to help on this?
|February 9, 2012, 12:39||
Retired from CFD Online
Join Date: Mar 2009
Location: Ann Arbor, MI
Blog Entries: 1Rep Power: 38
I assume you are using the octree tetra mesher...
In an effort to be robust and ignore small bits of geometry that you don't need, the algorithm checks for surface elements with the same volume material on either side. If it finds this situation, it deletes the element.
In your case, this is happening because you have a small hole or gap... When your mesh is large enough, it walks over this gap and you are fine. But when you adjust your settings, the finer mesh falls thru the gap and the solid volume fills with fluid, which then results in the removal of the surface mesh...
There are lots of ways to fix this... but here are two;
1) to find the leak, try putting a material point inside the solid region, then when it fills it will detect it as a leak and show you the path... Then you can fix the geometry to prevent leakage. In many cases, the problem may be due to a closely spaced pair of yellow curves... Often just building topology with a larger tolerance or even manually deleting one of the yellow curves will be enough to fix the problem. In other cases you may need to create a patch surface or something like that.
2) To proceed anyway (without fixing geometry), go into Mesh (tab) => Params by parts and check the box for "internal wall". This option is meant to allow for zero thickness baffles, but in this case you would simply be telling the mesher not to delete the surface mesh even though the inside fills up... Then I would go and delete the volume mesh... Then run a check for single edges, find the hole and repair it (mesh from edges, merge nodes, create elements, what ever). Then Run Delaunay to regenerate the volume mesh and continue on with your day...
|Thread||Thread Starter||Forum||Replies||Last Post|
|2D Mesh Generation Tutorial for GMSH||aeroslacker||Open Source Meshers: Gmsh, Netgen, CGNS, ...||12||January 19, 2012 04:52|
|Problem in clearing generated mesh||siara817||STAR-CCM+||3||April 4, 2011 08:44|
|snappyHexMesh won't work - zeros everywhere!||sc298||OpenFOAM Native Meshers: snappyHexMesh and Others||2||March 27, 2011 21:11|
|Domain Imbalance||HMR||CFX||3||March 6, 2011 21:10|
|RPM in Wind Turbine||Pankaj||CFX||9||November 23, 2009 05:05|