CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] How to mesh a 3 lenz turbine blade in rotating domain

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By PSYMN

Reply
 
LinkBack Thread Tools Display Modes
Old   March 10, 2012, 07:25
Default How to mesh a 3 lenz turbine blade in rotating domain
  #1
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Hi,

I need to build a prototype VAWT for my final year project, hence I need to do some simulation before fabricate. But I need to know how to mesh a 3 lenz blade in a rotating circular mesh, so I need help and guidance. Below is a top view picture of the lenz turbine blade.

CTan22 is offline   Reply With Quote

Old   March 10, 2012, 09:30
Default
  #2
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
anyone can help????
CTan22 is offline   Reply With Quote

Old   March 11, 2012, 08:33
Default
  #3
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Draw a concentric circle (centered on the center of rotation)... That should divide your domain into two regions... The outer region and the rotating region... Make sure your geometry has two separate parts. Mesh everything. You probably want inflation layers (aka boundary layers or prism layers) on all those parts that represent your wind turbine...

Then go to solver setup and make sure your circular domain is rotating...
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   March 11, 2012, 11:09
Default
  #4
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Quote:
Originally Posted by PSYMN View Post
Draw a concentric circle (centered on the center of rotation)... That should divide your domain into two regions... The outer region and the rotating region... Make sure your geometry has two separate parts. Mesh everything. You probably want inflation layers (aka boundary layers or prism layers) on all those parts that represent your wind turbine...

Then go to solver setup and make sure your circular domain is rotating...
Hi Simon thank for your guidance, but I got one question on how to setup a mesh topology on three blade in a rotating domain. I always see is a single blade meshing, but if applied to multiple blade I'm wonder how does the mesh topology look like.

So if possible is there any reference I can read through, so I can do it my self. But once again thank for your effort to guide me.
CTan22 is offline   Reply With Quote

Old   March 11, 2012, 17:52
Default
  #5
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Oh, you want a blocking strategy...

First, you will want to generate the mesh for just one of the 3 blades, but make it periodic and then copy rotate the mesh later...

In order for the mesh to be periodic, you need equal numbers of nodes upstream and downstream, so you can't just do a CGrid to capture the C shape of your blocking... I recomend an HGrid for the region between the hub and the rotating boundary (or a quarter Ogrid if you didn't have a hub), and then an Ogrid for your blade... Split the Ogrid in half and associate part of the middle of the Ogrid with you geometry where appropriate... This will give you nice boundary layer mesh on both sides of your mesh...

This is what I show in these pics... I also smoothed the mesh, although that isn't really necessary...

I suppose it could have been about 2 radial split simpler than this if I wanted also... but this was just a 5 minute first try...

But you could also go fancier than that... you could put another Ogrid behind the curved portion to better capture the strong swirl that will be there, etc...
Attached Images
File Type: jpg CTAN22_01.jpg (52.4 KB, 110 views)
File Type: jpg CTAN22_02.jpg (98.3 KB, 102 views)
File Type: jpg CTAN22_03.jpg (94.3 KB, 82 views)
File Type: jpg CTAN22_04.jpg (98.1 KB, 85 views)
Far likes this.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   March 11, 2012, 17:57
Default
  #6
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Oh yea, this is just the mesh for the central rotating region... around that you would be doing a simple mesh of the flow domain with a circle in the middle of it... How you block that stationary zone will be based on the shape of your outer region, but it will involve an Ogrid for the circular inner boundary...
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   March 22, 2012, 12:17
Default
  #7
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Quote:
Originally Posted by PSYMN View Post
Oh, you want a blocking strategy...

First, you will want to generate the mesh for just one of the 3 blades, but make it periodic and then copy rotate the mesh later...

In order for the mesh to be periodic, you need equal numbers of nodes upstream and downstream, so you can't just do a CGrid to capture the C shape of your blocking... I recomend an HGrid for the region between the hub and the rotating boundary (or a quarter Ogrid if you didn't have a hub), and then an Ogrid for your blade... Split the Ogrid in half and associate part of the middle of the Ogrid with you geometry where appropriate... This will give you nice boundary layer mesh on both sides of your mesh...

This is what I show in these pics... I also smoothed the mesh, although that isn't really necessary...

I suppose it could have been about 2 radial split simpler than this if I wanted also... but this was just a 5 minute first try...

But you could also go fancier than that... you could put another Ogrid behind the curved portion to better capture the strong swirl that will be there, etc...
Hi Simon,

Sorry for the late reply as I try to figure out how to get the blocking you have suggested. But after I have done with the blocking, it doesn't look good. Can you kindly advice? Thank.
Attached Images
File Type: jpg blade1.JPG (67.5 KB, 72 views)
File Type: jpg blade.JPG (30.0 KB, 51 views)
Attached Files
File Type: zip BLADE.zip (10.2 KB, 15 views)
CTan22 is offline   Reply With Quote

Old   March 22, 2012, 12:44
Default
  #8
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,914
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
blocking is good. Problem might be related to association. Could you plz also attach the .blk file
Far is offline   Reply With Quote

Old   March 22, 2012, 12:48
Default
  #9
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Quote:
Originally Posted by Far View Post
blocking is good. Problem might be related to association.
Hi Far thank for the advice, I will look on the associate issue and see whether can solve the problem.
CTan22 is offline   Reply With Quote

Old   March 22, 2012, 12:56
Default
  #10
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Quote:
Originally Posted by Far View Post
blocking is good. Problem might be related to association. Could you plz also attach the .blk file
Here the file.
Attached Files
File Type: zip Lenz_Blade.zip (19.4 KB, 21 views)
CTan22 is offline   Reply With Quote

Old   March 22, 2012, 13:59
Default
  #11
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,662
Blog Entries: 1
Rep Power: 35
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
I don't have time to look at the blocking, but I agree with Far, it looks like you have associated internal edges with curves and some of the external edges (top left) that should be assoicated with curves are just surface associated.

I can tell this by the color...

Green => associated to curve

White/Black => Associated to surface

Cyan blue => Color the internal edges should be... Not associated to anything.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   March 22, 2012, 14:01
Default
  #12
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,914
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
It was association problem. Blocking is not good in few blocks as highlighted.
Updated blocking file is attached.

Attached Files
File Type: zip lenzblade.zip (4.3 KB, 14 views)

Last edited by Far; March 22, 2012 at 15:22. Reason: Couldn't attach image due to loadshedding
Far is offline   Reply With Quote

Old   March 22, 2012, 14:03
Default
  #13
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Thank for the advice, Simon. Now I know what went wrong.
CTan22 is offline   Reply With Quote

Old   March 22, 2012, 14:05
Default
  #14
New Member
 
anonymous
Join Date: Mar 2012
Posts: 8
Rep Power: 5
CTan22 is on a distinguished road
Quote:
Originally Posted by Far View Post
It was association problem. Blocking is not good in few blocks as highlighted.
Updated blocking file is attached.
Thank Far!! Appreciate for your effort to spot my mistake and correct it. Really thank alot.
CTan22 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
3D Hybrid Mesh Errors DarrenC ANSYS Meshing & Geometry 11 August 5, 2013 06:42
Vertical Axis Wind Turbine Rotating Domain Problems TWaung CFX 4 May 1, 2012 03:14
2D Mesh Generation Tutorial for GMSH aeroslacker Open Source Meshers: Gmsh, Netgen, CGNS, ... 12 January 19, 2012 04:52
RPM in Wind Turbine Pankaj CFX 9 November 23, 2009 05:05
fluent add additional zones for the mesh file SSL FLUENT 2 January 26, 2008 12:55


All times are GMT -4. The time now is 08:21.