CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] not completing mesh of the surface

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree3Likes
  • 1 Post By PSYMN
  • 2 Post By PSYMN

Reply
 
LinkBack Thread Tools Display Modes
Old   March 17, 2012, 12:41
Default not completing mesh of the surface
  #1
Senior Member
 
mohamed khedr emam
Join Date: Oct 2011
Location: Egypt
Posts: 120
Rep Power: 5
m5edr is on a distinguished road
This is a turbine blade
After many trials , the mesh of the surface is not cover the whole bade (specially along the trailing edge !!)


iam used various mesh types in Icem and played with mesh sizes but not able to solve this problem

Any help pls
Attached Images
File Type: jpg 25.jpg (37.8 KB, 67 views)
File Type: jpg 26.jpg (48.7 KB, 82 views)
m5edr is offline   Reply With Quote

Old   March 17, 2012, 22:16
Default
  #2
Senior Member
 
Rikio
Join Date: Mar 2009
Location: SH, China
Posts: 182
Blog Entries: 1
Rep Power: 7
rikio is on a distinguished road
Send a message via Skype™ to rikio
You need to adjust the Edge Criterion under Volume Meshing Parameters. It determines to what extent a tetra is cut to represent geometry. The entered value is a factor of the tetra edge. After subdivision, if a tetra edge intersects an entity (surface), the tetra will be cut if the subdivision of the edge from the intersection is less than the prescribed value.

Looking into this thread at Help at Mesh-Global Mesh Setup-Volume Meshing Parameters-Tetra/Mixed-Robust(Octree)
rikio is offline   Reply With Quote

Old   March 19, 2012, 13:07
Default
  #3
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,651
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Or turn on "thin cuts"

You may also need to reduce your mesh size.

This is a "behavior" associated with Octree mesh.

Another option would be to use another method (such as Patch Conforming Surface Mesh)...
ahmadreza likes this.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   March 19, 2012, 13:45
Default
  #4
Senior Member
 
mohamed khedr emam
Join Date: Oct 2011
Location: Egypt
Posts: 120
Rep Power: 5
m5edr is on a distinguished road
Yes, i discovered that 1 day ago >>>> thin cut solve the problem

thanks
m5edr is offline   Reply With Quote

Old   March 21, 2012, 11:52
Default
  #5
New Member
 
Join Date: Mar 2012
Posts: 3
Rep Power: 4
andrearudenick is on a distinguished road
When you say "turn on thin cuts", do you mean to turn on the function "Define thin cuts" of the Volume Meshing Parameters section? or is there another ICEM function applied to shell meshing instead of volumen meshing? Because at the beginning you were talking about a surface mesh, and I'm having the same problem.

Thanks!
andrearudenick is offline   Reply With Quote

Old   March 21, 2012, 12:04
Default
  #6
Senior Member
 
mohamed khedr emam
Join Date: Oct 2011
Location: Egypt
Posts: 120
Rep Power: 5
m5edr is on a distinguished road
Quote:
Originally Posted by andrearudenick View Post
When you say "turn on thin cuts", do you mean to turn on the function "Define thin cuts" of the Volume Meshing Parameters section? or is there another ICEM function applied to shell meshing instead of volumen meshing? Because at the beginning you were talking about a surface mesh, and I'm having the same problem.

Thanks!

I mean "Define thin cuts" of the Volume Meshing Parameters section"
but first you should create two parts (of thin cut) at CREATE PART
m5edr is offline   Reply With Quote

Old   March 21, 2012, 12:12
Default
  #7
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,651
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
Right, Define Thin Cuts affects how the surface mesh is produced with the "patch independent (Octree)" meshing approach.

It is essentially an algorithm that says "if a surface element has a node on part A, then it should not have a node on Part B." Therefore you need to make sure that the two sides are in different parts. Also, if the two sides meet at a common curve, the curve must be in a 3rd part (separate from the two sides) or it will be impossible for the algorithm to succeed and it will fail out with a message.

Best regards,

Simon
Far and dongjia like this.
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   March 21, 2012, 12:20
Default
  #8
Senior Member
 
mohamed khedr emam
Join Date: Oct 2011
Location: Egypt
Posts: 120
Rep Power: 5
m5edr is on a distinguished road
hi simon

iam very sorry for this overlap (I'm feel it awkward )
I posted a problem in ICEM
could you show it
problem in periodic

sorry again
m5edr is offline   Reply With Quote

Old   March 21, 2012, 12:36
Default
  #9
Senior Member
 
PSYMN's Avatar
 
Simon Pereira
Join Date: Mar 2009
Location: Ann Arbor, MI
Posts: 2,651
Blog Entries: 1
Rep Power: 34
PSYMN has a spectacular aura aboutPSYMN has a spectacular aura about
@m5edr...

Yes, I don't have time to read all the threads these days and I am missing more than I hit (I appreciate others on CFD-Online who can also help out).

If you want me to notice a thread, please don't pollute an unrelated thread. I would rather you just send me a private message with a link to the thread...

Best regards,

Simon
__________________
-----------------------------------------
Please help guide development at ANSYS by filling in these surveys

Public ANSYS ICEM CFD Users Survey

This second one is more general (Gambit, TGrid and ANSYS Meshing users welcome)...

CFD Online Users Survey
PSYMN is offline   Reply With Quote

Old   April 24, 2012, 19:30
Default
  #10
Senior Member
 
Ananthakrishnan.A.S
Join Date: Feb 2012
Location: Paris, France
Posts: 123
Rep Power: 6
Ananthakrishnan is on a distinguished road
Send a message via Skype™ to Ananthakrishnan
Hi,
I had this problem and "define thin cut" did help. Now i have a different problem which is i am unable to create prism elements on the airfoil surfaces (these are the surface with which i have defined my "thin cut"). Is there anything i am missing??
Ananthakrishnan is offline   Reply With Quote

Old   April 24, 2012, 19:37
Default
  #11
Senior Member
 
mohamed khedr emam
Join Date: Oct 2011
Location: Egypt
Posts: 120
Rep Power: 5
m5edr is on a distinguished road
Quote:
Originally Posted by Ananthakrishnan View Post
Hi,
I had this problem and "define thin cut" did help. Now i have a different problem which is i am unable to create prism elements on the airfoil surfaces (these are the surface with which i have defined my "thin cut"). Is there anything i am missing??
check
1- if you checked "create prism layers" in Compute mesh window
2- if you checked "prism" in Part mesh setup window
m5edr is offline   Reply With Quote

Old   April 25, 2012, 03:43
Default
  #12
Senior Member
 
Ananthakrishnan.A.S
Join Date: Feb 2012
Location: Paris, France
Posts: 123
Rep Power: 6
Ananthakrishnan is on a distinguished road
Send a message via Skype™ to Ananthakrishnan
yeah..i have...
If i undefine the thin cut, then prism gets created. If i define thin cut, then it does'nt..
Ananthakrishnan is offline   Reply With Quote

Old   April 25, 2012, 10:04
Default
  #13
New Member
 
Sergio Macchiavello
Join Date: Mar 2012
Posts: 7
Rep Power: 4
OneDotThree is on a distinguished road
I'm replying to this posts as I have problem similar to the previous ones.

I'm trying to create an unstructured mesh for a swirler. In fact I'm meshing 1/8 of the swirler and applying periodic conditions.

The problem is that some elements miss in proximity of some periodic face edges and appear in the corresponding periodic surface. in other words there is a hole at one side and there are exceeding elements (outside the surface) at the other side.

Moreover these elements have a low quality (below 0.2), so I can't ignore them.

I tried to use the define thin cutsoption and to define different values in the edge criterion but I couldn't resolve the problem.

I'm attaching some picture to explain better:
Attachment 12730 Attachment 12731 Attachment 12732

In the first picture in green you can see the periodic faces, in the second one the holes and in the third the elements outside the geometry.

I would be very grateful if someone could help me, thanks.
OneDotThree is offline   Reply With Quote

Old   May 5, 2012, 13:09
Default
  #14
New Member
 
Sergio Macchiavello
Join Date: Mar 2012
Posts: 7
Rep Power: 4
OneDotThree is on a distinguished road
Could somebody give me an answer?
I resolved this problem accidentaly but it reappears if i change any mesh parameters (also in not involved parts).
It is very annoying, I've worked on it several days but I can't manage.
I would be able also to send you the project files.
Please help me!
OneDotThree is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
how to set periodic boundary conditions Ganesh FLUENT 13 January 22, 2014 05:11
No layers in a small gap bobburnquist OpenFOAM Native Meshers: snappyHexMesh and Others 2 November 25, 2012 09:54
snappyHexMesh won't work - zeros everywhere! sc298 OpenFOAM Native Meshers: snappyHexMesh and Others 2 March 27, 2011 22:11
Error : Self intersecting surface mesh, computing intersections & Error : Impossible velan Open Source Meshers: Gmsh, Netgen, CGNS, ... 0 June 29, 2009 01:48
virtual geometry richard FLUENT 4 January 7, 2009 06:16


All times are GMT -4. The time now is 11:13.