CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CD-adapco

Fluid forces on exhaust valves

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   August 30, 2000, 07:36
Default Fluid forces on exhaust valves
  #1
Lars Ola Liavåg
Guest
 
Posts: n/a
Dear colleagues,

I am studying the gas forces acting on the exhaust valves of a 4-stroke diesel engine. The intention is to apply the CFD results as BC's in a FEM analysis aimed at determining the valve deformation. Thus, the resultant force and its point of attack must either be calculated directly from the CFD results, or the wall force data output by STAR-CD (which appears to be the gas force in N acting on each surface shell) must be converted to force-per-area vertice data.

If anyone has experience from this sort of manipulation with STAR-CD results (and how to export them to I-DEAS), your advice would be very much appreciated.

Lars Ola
  Reply With Quote

Old   August 30, 2000, 11:38
Default Re: Fluid forces on exhaust valves
  #2
Robert Bland
Guest
 
Posts: n/a
Might I suggest you transfer surface pressure values -force is mesh dependent (use GETB to get the surface pressure and then CAVERAGE these values onto the vertices of the wall shells).

In general you would pull your IDEAS mesh into STAR, use PMAP to map the results across from STAR and then write out a list of force application commands for IDEAS with the GENERIC command
  Reply With Quote

Old   August 31, 2000, 01:58
Default Re: Fluid forces on exhaust valves
  #3
Lars Ola Liavåg
Guest
 
Posts: n/a
Hello Robert,

If the contribution of the static pressure to the total gas forces is much larger than that of the shear forces, I guess porting of the results to I-DEAS becomes simpler since I don't have to play around with vectors.

Nevertheless, I would still like to assess the magnitude of the shear force part. As you mention, force is mesh dependent, and interpreting the results as displayed in PROSTAR is therefore not very easy. It would be of value to transform the cell force data into force-per-area data on the vertices regardless of whether or not the results will be ported to I-DEAS. Any suggestions on how to do this?

Lars Ola
  Reply With Quote

Old   August 31, 2000, 17:06
Default Re: Fluid forces on exhaust valves
  #4
Robert Bland
Guest
 
Posts: n/a
You could normalise the forces by the cell area (using OPERATE) before mapping instead of using pressure. You could also use PSYS on the forces if you, for example, wanted to map in a cylindrical co-ordinate system.

If the grids had broadly similar densities then you may be OK using this approach - the mapping is not conservative so you need to be careful. An overall force level comparison of the original and mapped object should give a first order estimate as to whether the mapping has been successful. Contour plots would also help.
  Reply With Quote

Old   September 1, 2000, 06:59
Default Re: Fluid forces on exhaust valves
  #5
Lars Ola Liavåg
Guest
 
Posts: n/a
Thanks for the advice. I loaded in the cell areas and divided the forces by them obtaining a fairly smooth distribution of surface stress. However, I have a couple of questions regarding PROSTAR's handling of wall forces. When using the getw,sftot command, I get exactly the same forces on the elements as when using getw,fxyz - regardless of the pressure option used. This along with the fact that the lowest value of the surface stresses occurs under the valves, where at the same time the pressure is known to be largest, leads me to think that the actual total force is not at all calculated by PROSTAR in my case. So: ??????????

Another thing is that after performing the post register operations on the force components in registers 1-3, PROSTAR responds to the replot command by saying that no vector data is available. typing wplot works, but the interactivity of the GUI is somewhat hampered by the disliking of the replot command. Is this a known problem?

Yet another question: In order to map the results on to a (coarser) I-DEAS mesh, do I have to use the cave command first?

Lars Ola
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Cavitation In Valves T Cymmer Main CFD Forum 2 August 24, 2009 04:46
poppet valves Harry FLUENT 2 December 5, 2007 14:24
New Design for Valves using CFD Internal Combustion Engines Main CFD Forum 1 April 9, 2007 13:01
valves in es-ice Colin CD-adapco 0 August 8, 2005 12:39
simulation of hydraulic valves NM Urs Main CFD Forum 0 December 5, 2000 10:31


All times are GMT -4. The time now is 00:31.