CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CD-adapco

Ship Resistance problems using CCM+

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 28, 2007, 18:58
Default Ship Resistance problems using CCM+
  #1
Dan
Guest
 
Posts: n/a
Hi,

Has anyone done any ship resistance problems? I'm using CCM+ 2.06.004, and I'm trying to solve for the wave pattern as an implicit unsteady problem using VOF for the wave profile. The problem starts off ok, and the wave pattern starts to look about right, but i find the longer i run my problem, the further my resistance values decay, and i don't seem to be able to get a steady state solution at all. Any suggestions on these kind of problems?
  Reply With Quote

Old   April 2, 2007, 11:26
Default Re: Ship Resistance problems using CCM+
  #2
thomas
Guest
 
Posts: n/a
... what time step is used? How many inner iterations?

... take care for high grid resolution where both phases are mixing!
  Reply With Quote

Old   April 2, 2007, 12:13
Default Re: Ship Resistance problems using CCM+
  #3
Dan
Guest
 
Posts: n/a
I am using a time step of 0.025s, and 15 inner iterations.

I'm also using k-epsilon for turbulence, any thoughts if I should change that?
  Reply With Quote

Old   April 3, 2007, 02:25
Default Re: Ship Resistance problems using CCM+
  #4
thomas
Guest
 
Posts: n/a
... may be try time step 0.01s to 0.0025! ... may be inner iteration of 10 will do!

... I have no arguments agains k-epsilon, but check if your boundary layer thickness is ok (use Y+)! This is a little bit difficult, because of the two layers! So may be try to optimize for the water area!

... have a look if your surface tension, gravity and buoyancy is on/correct! Otherwise you will get funny results!

... no more ideas so far!

Good luck!

  Reply With Quote

Old   April 3, 2007, 03:54
Default Re: Ship Resistance problems using CCM+
  #5
Peter
Guest
 
Posts: n/a
Dan,

Seriously consider contacting CD-adapco and asking for advice and assistance in setting this up properly.

To calculate the wave pattern around a ship hull you have to calculate a sharp interface between the two fluids. Mixing the two fluids will at best smear the interface leading to poor results and at worst leave you with a two-phase mush and no wave pattern.

Also a ship is subject to dynamic sinkage and trim effects. How are you including these in the calculation? STAR-CCM+ currently does not support moving mesh.

The best advice you will receive today is to call CD-adapco.

Regards Peter

  Reply With Quote

Old   April 3, 2007, 08:05
Default Re: Ship Resistance problems using CCM+
  #6
pp
Guest
 
Posts: n/a
Could you describe your boundary conditions (eg. outlet domain)?

Regards, pp
  Reply With Quote

Old   April 3, 2007, 12:20
Default Re: Ship Resistance problems using CCM+
  #7
Dan
Guest
 
Posts: n/a
Thanks for the help and input to everyone who's contributed, its much appreciated.

Just to give a brief description of my problem set-up to those who've asked, and a run down as to what I've figured out so far:

I use a user function for hydrostatic pressure on my outlet, and I define the water level at both my inlet & my outlet, and initialize it in initial conditions as well.

I had a refinement layer to capture the wave pattern locally for a few ship lengths around the hull, this was giving me problems, as it creates numeric waves where the refinement layer ends. This refinement layer needs to be extended as far upstream and to the side as the mesh goes!!!

Around the keel and bulbous bow, the extrusion layer tends to collapse around, I found that was contributing to my oscillating resistance values (still trying to figure out how to resolve this, any ideas?). I create my surfaces in a program called Rhino, then import to ProSurf to triangulate / fix the iges surfaces, before I can get it into Star CCM+ I need to find ways to improve this process.

Sinkage and trim are an issue. I have a large volume of experimental data for similar hulls, so I tend to approximate the sinkage and trim for each hull rather than ignore it or try to calculate it iteratively. Fortunately for large vessels at moderate Froude numbers, sinkage and trim can be quite small.

I've also been working with CD-Adapco as well. Thanks again everyone for your help.
  Reply With Quote

Old   May 10, 2007, 16:29
Default Re: Ship Resistance problems using CCM+
  #8
Peter
Guest
 
Posts: n/a
Dan,

What sort of advice did CD-adapco provide on this issue?

Just curious ...

Regards Peter
  Reply With Quote

Old   May 14, 2007, 12:12
Default Re: Ship Resistance problems using CCM+
  #9
Dan
Guest
 
Posts: n/a
In the end, my biggest problem was having refined cells around the hull to get low y+ values. This was giving me all sorts of problems at the free surface, and in general needs to be avoided. I've found that the free surface is extremely sensitive to mesh transitions. The guys at CD-adapco had quite a thorough look through my model, and this is the conclusion we came to. This of course leaves you with quite a few cells, but i've now finished quite a few different hull forms successfully, with accurate results compared to experimental work.
  Reply With Quote

Old   April 6, 2011, 04:27
Default
  #10
New Member
 
Join Date: Mar 2011
Posts: 3
Rep Power: 0
Fn80 is on a distinguished road
so finally,how you proceed?
changing growth rate?
Fn80 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
CCM+ Outlet BC for Ship Resistance Steve CD-adapco 3 May 8, 2008 19:12
boundary conditions for compute resistance of ship Bruce CFX 1 April 18, 2007 11:30
Analysis of ship hull resistance and properties AL Main CFD Forum 0 July 10, 2006 15:34
Ship Wave Making Resistance Yasser CFX 7 April 24, 2006 14:56
Ship waves resistance problem Renato Skejic Main CFD Forum 4 July 25, 2002 08:48


All times are GMT -4. The time now is 02:17.