CFD Online Logo CFD Online URL
Home > Forums > CFX

Outlet/opening boundary condition

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By em11g09

LinkBack Thread Tools Display Modes
Old   November 21, 2012, 06:37
Post Outlet/opening boundary condition
New Member
Ed Musgrove
Join Date: Nov 2012
Posts: 2
Rep Power: 0
em11g09 is on a distinguished road

I am currently trying to model 2D free surface flow through a sump. I am having issues with my outlet boundary as I want to set it so there is no defined pressure or velocity. If I do set a pressure condition then fluid wants to flow back into the system due to the head loss through the sump. If I resolve this using an open boundary it is not realistic.

I have looked at the 2d flow over bump tutorial but that sets a down stream water level which I don't want to do.

Is there any outlet boundary condition or expression I can use which does not need to have a pressure or velocity set?

Thank you
em11g09 is offline   Reply With Quote

Old   November 21, 2012, 10:04
Senior Member
Join Date: Mar 2009
Location: Brazil
Posts: 250
Rep Power: 12
brunoc is on a distinguished road
You can set the pressure level as an explicit result of the water level calculated by the solver. For a 2D case with a rectangular outlet boundary condition and gravity in +Y, this might do it:


      DenRef = 1.185 [kg m^-3]
      DenWater = 997 [kg m^-3]
      DenH = (DenWater - DenRef)

      areaWater = areaInt(Water.Volume Fraction)@outflow
      bottomYposition = 0 [m]
      domainWidth = 0.01 [m]
      aveWaterHeight = bottomYposition + areaWater / domainWidth

      HidPressure = DenH * g * (aveWaterHeight - y) * step( (aveWaterHeight - y)/1[m] )

where 'HidPressure' is the value you set at the outflow region. It will probably make convergence harder, since you're no longer tying the outlet condition.

brunoc is offline   Reply With Quote

Old   November 22, 2012, 10:51
New Member
Ed Musgrove
Join Date: Nov 2012
Posts: 2
Rep Power: 0
em11g09 is on a distinguished road
Thanks that has worked for me. I have also run the test with a long channel downstream of the sump. Both methods give roughly the same results.

Thanks again

brunoc likes this.
em11g09 is offline   Reply With Quote


boundary condition, outlet boundary, outlet boundary condition

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
Radiation interface hinca CFX 15 January 26, 2014 18:11
An error has occurred in cfx5solve: volo87 CFX 5 June 14, 2013 17:44
Setting outlet Pressure boundary condition using CAFFA code Mukund Pondkule Main CFD Forum 0 March 16, 2011 04:23
Domain Imbalance HMR CFX 3 March 6, 2011 21:10
How to set boundary condition in Fluent for the fo Peiyong FLUENT 1 November 10, 2006 12:44

All times are GMT -4. The time now is 10:54.