
[Sponsors] 
November 23, 2012, 02:55 
Why average volume fraction greater than 1? (attached files)

#1 
New Member
Titus Ofei
Join Date: Nov 2012
Posts: 13
Rep Power: 5 
Hi all CFX users
I have encountered some CFX post results which seem to me unrealistic. I am simulating twophase flow (particlesliquid) through a horizontal concentric annular wellbore at steady state condition. I am using 'particle transport solids' as the morphology for the particle The particles are injected into the annulus at a constant rate and random. I also considered both oneway and full coupling to model the transport of the particle. I want to determine the concentration of particles in the annulus. So I created a plane and polyline at the axial center of the annular section. I used the polyline to create a chart of average cuttings(particle) concentration verses axial distance. The results are over unity (1) which is unrealistic. What could be the error here? I have attached more plots to see how the particles are formed along the axial length of the wellbore. Your contribution to this problem is welcome. Further information required will be made available. Many thanks 

November 23, 2012, 05:20 

#2 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 12,568
Rep Power: 97 
This is because you are using particle tracking in a regime it is not suited for, well at least not with the submodels you are using. Particle tracking does not account for maximum packing and particle to particle interactions, so the volume fraction can go as high as it likes. Also note that lagrangian particle tracking is only good for low particle volume fractions  you obviously have high volume fractions so I would suggest the particle tracking model is not a suitable model for this application.
You need to include a packing model to make it more realistic. I would forget about particle tracking and move to eularian particle tracking where there are a few models which can handle dense volume fractions and maximum particle packing. An alternate approach would be to couple with a DEM software which can handle the particle packing  but this would be additional software and all the fun and games of coupling software together. 

November 23, 2012, 09:12 

#3  
New Member
Titus Ofei
Join Date: Nov 2012
Posts: 13
Rep Power: 5 
Quote:
I can understand from your reply that i need to go for Eulerianparticle tracking. My understanding from the manual (cfx_mod) is that, for Eulerianparticle model, the liquid phase should have a morphorlogy as continuous fluid while the solid phase as dispersed solid. Is it the same as you are suggesting? This approach is seeking for the volume fraction of each phase at the inlet boundary condition. I'm quite in a dilemma since my aim is to determine the volume fraction of solids at the end of the simulation run. A clear description of my problem: (drilling process): fluid (water) flows through the inlet of annular pipe at a constant rate and flows out. Cuttings (solids) are also injected at a constant rate through the inlet of the annular pipe and flows out. What is the concentration (volume fraction) of cuttings at the end of the simulation run. I'm considering steady state. Once again, many thanks for your patience Titus 

November 25, 2012, 05:02 

#4  
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 12,568
Rep Power: 97 
Quote:
Quote:
Based on your initial model the cuttings are much heavier than water and quickly fall out of the flow and form a bed on the bottom. Is the physically realistic? 

November 25, 2012, 10:26 

#5  
New Member
Titus Ofei
Join Date: Nov 2012
Posts: 13
Rep Power: 5 
Quote:
Yes, in my initial model the cuttings are much heavier than the water. This is physically realistic in drilling (oil and gas) operations. This model is a horizontal wellbore where the drilled cuttings settle to form a bed due to gravity effect as it travels from upstream(downhole) to downstream(surface). I will try your suggestion and give you feedback. Once again, many thanks for your time Titus 

November 25, 2012, 17:37 

#6 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 12,568
Rep Power: 97 
In this case then things like scour, settling and packing are important. This will be a challenege in CFX.... Definitely try Eularian approaches, but you might need to move to a CFD code with an actual scour model. Flow3D has one, but am not sure how applicable it is to this model.


Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
multiphase flow ，mass and volume fraction imbalance  sope111  CFX  11  July 15, 2012 08:20 
Solving the Volume Fraction Equation in a Multiphase M.  Max585  FLUENT  1  March 20, 2012 08:49 
average weighted area of volume fraction at output  umar959  Main CFD Forum  0  January 20, 2012 03:47 
interDyMFoam  change in volume fraction  gopala  OpenFOAM Running, Solving & CFD  0  April 27, 2009 10:46 
On the damBreak4phaseFine cases  paean  OpenFOAM Running, Solving & CFD  0  November 14, 2008 22:14 