What this error message means?
 

Details of error:-
----------------
Error detected by routine PEEKCS
CDANAM = BCP72 /VARIABLES/ENTHSTAT_FL1 /BCTYPE
CRESLT = NONE

Current Directory : /FLOW/BOUNDCON/ZN21

+--------------------------------------------------------------------+
| ERROR #001100279 has occurred in subroutine ErrAction. |
| Message: |
| Stopped in routine MEMERR |
| |
| |
| |
| |
| |
+--------------------------------------------------------------------+

+--------------------------------------------------------------------+
| An error has occurred in cfx5solve: |
| |
| The ANSYS CFX solver could not be started, or exited with return |
| code 255. No results file has been created. |
+--------------------------------------------------------------------+

End of solution stage.

+--------------------------------------------------------------------+
| The following user files have been saved in the directory |
| /cluster/home03/mavt/linin/complete_filezilla/flow_turning_check_- |
| 006: |
| |
| mon |
+--------------------------------------------------------------------+


+--------------------------------------------------------------------+
| An error has occurred in cfx5solve: |
| |
| Indirect start method returned non-zero exit code |
+--------------------------------------------------------------------+


+--------------------------------------------------------------------+
| An error has occurred in cfx5solve: |
| |
| Indirect solver job failed |
+--------------------------------------------------------------------+


+--------------------------------------------------------------------+
| Warning! |
| |
| After waiting for 60 seconds, 1 solver manager process(es) appear |
| not to have noticed that this run has ended. You may get errors |
| removing some files if they are still open in the solver manager. |
+--------------------------------------------------------------------+

Looks like it cannot find static enthalpy on a boundary condition. Did you define the temperature of other flow conditions correctly on a boundary condition?

How did you see that?

That looks like static enthalpy - and enthalpy is strongly linked to temperature.

That looks like a boundary condition call.

From there and a few educated guesses and you have it :)

Did you get this error by changing the ccl via command line (either injection during run or prior to start)?

I have had this happen to me when I changed a boundary condition by that method. For example, I changed a wall to an opening using a ccl text file and I forgot to provide the temperature condition. It has also occured when I didnt get the formatting exactly right on that change.

error is because of lack of information in varibale name about the belonging phase
 

Hello,
I had somehow the similar problem.
I defined some new variables from multiplication of ordinary variables.
for example:
"VelocityMultiplication Expr": fluid.Velocity u* fluid.Velocity v
Then "VelocityMultiplication Var": defined via algebraic equation from the above expression

I realized, by Using the new variable, I forgot to write the fluid phase name behind the variable.

PhaseName.VariableName
in above example, if you want to use, then use: fluid.VelocityMultiplication Var >> like ave(fluid.VelocityMultiplication Var)@Domain

I got the above error, because I used only new Variable name without mentioning the phase belong to.