CFD Online Discussion Forums

CFD Online Discussion Forums (http://www.cfd-online.com/Forums/)
-   CFX (http://www.cfd-online.com/Forums/cfx/)
-   -   CFX output for ParaView (http://www.cfd-online.com/Forums/cfx/126494-cfx-output-paraview.html)

siw November 19, 2013 08:20

CFX output for ParaView
 
Hi,

I need to use either ParaView or VisIt post-processors packages rather than CFD-Post for a particular task.

Having looked through both of these packages there is not a native CFX input, unlike Fluent, that I can find. What is the recommended way of getting CFX results in ParaView and VisIt?

Thanks.

khoopes November 19, 2013 12:02

I have found that exporting the results to ensight format using the solver manager works for my needs. Open the solver manager stand alone, and then tools -> export results then just select your .res file and select output format as ensight. Paraview should have no problem loading the resulting files.

siw November 20, 2013 03:11

Thanks,

I see that there are some options in the CFX-Solver Manager in the Ensight export: Ensight version 5, 6 or Gold and Format Binary or ASCII. Does it matter which are selected?

Lance November 20, 2013 03:13

I normally go with Gold (dont remember why :)) and binary (to reduce file size).

rkiranmat December 10, 2013 02:32

Regading Ensight format
 
Dear All,

I am working with Paraview. I have done my simulations using Ansys CFX and exported to Paraview readable format (EnSight). It has created *.case file with some more files.

I would like to know more details about all files expecially *.GEOM file.

Can you please help me to understand in details.

Thanks and Regards

Lance December 10, 2013 04:53

Quote:

Originally Posted by rkiranmat (Post 465618)
I would like to know more details about all files expecially *.GEOM file.
Can you please help me to understand in details.

What do you want to know about it? A google search on ensight file format will bring up thousands of hits, Im sure some of them are useful for you.

Jack001 March 23, 2016 14:43

I am using the CFX solver to output a file that can be read by Paraview. However the file only contains a few solver variables like velocity, pressure. I can view many many more in CFD post (for example the wall shear stress). Is there any way to export these variables to paraview?

Lance March 24, 2016 03:39

For ensight format:
set Results options/output level to 3
that will output ALL variables in the res file. There is no way (that I know of at least) to specify just a few variables.

Jack001 March 24, 2016 09:02

Thank you very much that definitely added the variables according to the CFX output prompt. However they don't seem to automatically appear in the paraview point arrays / cell arrays list where all the other variables are. I was hoping they would just load when I open the EnSight case file?

EDIT:

It seems CFX outputs two case files now one with the "level3" variables and the one I had before. Choosing the level 3 case file works perfectly. Thanks again for the help.


All times are GMT -4. The time now is 06:58.