CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

LES for flow over bluff body

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By ghorrocks

Reply
 
LinkBack Thread Tools Display Modes
Old   November 25, 2013, 22:00
Default LES for flow over bluff body
  #1
New Member
 
Join Date: Apr 2010
Location: Athens, Greece
Posts: 15
Rep Power: 7
sosat1012 is on a distinguished road
Hi all.

I would like to ask 2 things

Should I run a steady state simulation and use the steady state solution as the initialization for the transient (either way) LES or could i omit the steady state run? I know this is more a question related to the transient analysis and not LES itself but is there any difference in LES? Its the first time i do a LES and i am using CFX.

The simulation is about the airflow around a bluff body - something like a windbreak. It is supposed to be inside a wind tunnel. Usually i choose 30s as total time and 0.01s for the timestep size so its 3000 timesteps. I set the convergence at 10-4 RMS. Initially i do not get convergence in 3-5 loops as the cfx manual says. But quickly i do see convergence. Should i use more timesteps in order to have converged solutions in every timestep or could I just ignore the early non-converged ones?
sosat1012 is offline   Reply With Quote

Old   November 25, 2013, 22:52
Default
  #2
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,652
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
If you only care about the pseudo-steady state flow then anything you can do to make the initial condition closer to the final flow will mean you do not need to run as long. As yes, starting from a steady state result will help.

If you do not care about the start up transient then don't worry about the initial time steps. If the start up is important then yes, you better fix that up.

But you should consider using adaptive time stepping to automatically adjust the time steps. Be careful with LES though, sometimes the time step size always keeps moving with adaptive timesteps and that is not good. Also second order time differencing suffers when the time step size changes a lot. So if you know the time step size then it might be better to define a fixed step size.
sosat1012 likes this.
ghorrocks is offline   Reply With Quote

Old   November 26, 2013, 07:06
Default
  #3
New Member
 
Join Date: Apr 2010
Location: Athens, Greece
Posts: 15
Rep Power: 7
sosat1012 is on a distinguished road
Thanks a lot Glenn.

Oh one more thing.

So i am finally doing both. Two different configurations that the initial values for the transient - 2nd configuration- are taken by the converged steady state solution -1st configuration.

I read at the fluent manual that before running LES you should "use the solve/initialize/ init-instantaneous-vel text command to generate the instantaneous velocity field out of the steady-state RANS results".

Do i need to do something similar in CFX? I don't remember any option like that...(or i don't know how to do it)


Last edited by sosat1012; November 26, 2013 at 10:02.
sosat1012 is offline   Reply With Quote

Old   November 26, 2013, 17:53
Default
  #4
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,652
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
I don't think CFX has an equivalent option. You will just have to run it for a while and let the turbulent structures generate.
ghorrocks is offline   Reply With Quote

Old   November 27, 2013, 03:45
Default
  #5
Senior Member
 
Lance
Join Date: Mar 2009
Posts: 522
Rep Power: 11
Lance is on a distinguished road
Under 'Expert parameters/Physical Models/Turbulence Models' there is a setting: apply ic fluctuations for les.
Set it to true to apply random fluctuations to the initial results.
Lance is offline   Reply With Quote

Old   November 27, 2013, 05:33
Default
  #6
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,652
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Thanks for the tip Lance. I have never used that option - does it work well?
ghorrocks is offline   Reply With Quote

Old   November 27, 2013, 06:11
Default
  #7
Senior Member
 
Lance
Join Date: Mar 2009
Posts: 522
Rep Power: 11
Lance is on a distinguished road
Sort of. If I understand correctly it applies random fluctuations to the entire domain, and in my applications I have parts of the domain that are laminar. But it can be useful to kick-start the turbulence.
Lance is offline   Reply With Quote

Old   November 27, 2013, 07:43
Default
  #8
New Member
 
Join Date: Apr 2010
Location: Athens, Greece
Posts: 15
Rep Power: 7
sosat1012 is on a distinguished road
Yes i read it too in cfx manual. I did my first run without initial fluctuation and going to check my results in a couple of hours. I will run it again with initialization in fluctuations and compare. Thank you both guys!
sosat1012 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ANSYS Meshing] Simple Symmetry Mesh Question - Flow around Bluff Body Matlab69 ANSYS Meshing & Geometry 20 April 23, 2012 09:55
Bluff body used for diffuser testing lemat1 CD-adapco 0 December 5, 2009 10:11
LES simulation of bluff body at Re(d)=1200 arash_nl FLUENT 0 June 1, 2009 13:16
3d mesh of bluff body for LES Lukasz Mosakowski FLUENT 4 January 18, 2006 00:09
UDF for lift force on a bluff body sawa FLUENT 2 April 11, 2005 03:06


All times are GMT -4. The time now is 11:03.