# Variable Composition Mixture

 Register Blogs Members List Search Today's Posts Mark Forums Read

 January 10, 2014, 01:06 Variable Composition Mixture #1 Member   Alireza Safikhani Join Date: Dec 2010 Posts: 36 Rep Power: 7 Dear friends, I am simulating the smoke in air using Variable Composition Mixture. My problem has one inlet and one outlet. Unfortunately after converging the problem when I see the mass fraction of smoke in post process, the smoke in inlet is suddenly eliminated, please help me what is the fault? Regards

 January 12, 2014, 06:58 #2 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,704 Rep Power: 98 Can you post an image of what you are seeing and your CCL?

January 15, 2014, 05:22
#3
Member

Alireza Safikhani
Join Date: Dec 2010
Posts: 36
Rep Power: 7
Dear Glenn
Thanks for the consideration, I have uploaded a contour of mass fraction, as it is obvious the mass fraction at the inlet suddenly is vanished. Please help me in fact this problem is very important for me.

Regards
Attached Images
 Mass Fraction.jpg (53.5 KB, 11 views)

 January 15, 2014, 06:48 #4 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,704 Rep Power: 98 What does the flow vectors look like? Is the simulation converged? Has it run for enough pseudo time? If your time is too short that might be as far as the inlet fluid has got in the time you have run.

 January 15, 2014, 09:20 #5 Member   Alireza Safikhani Join Date: Dec 2010 Posts: 36 Rep Power: 7 Dear Glenn Yes the problem is converged and the velocity vectors are good. In fact I have tried both "Additional Variables" and "Variable Composition Mixture" methods and this fault is occurred in both methods. What do you mean by this sentence "If your time is too short that might be as far as the inlet fluid has got in the time you have run" would you please define more? Regards

 January 15, 2014, 17:36 #6 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,704 Rep Power: 98 CFX uses a psuedo transient approach for steady state simulations. That means that the fluid is convects from the inlet to the outlet in a fashion similar to a true transient flow. So if you start with initial condition AV=0 everywhere and AV=1 at the inlet, it will take some time for the AV to convect through the domain and reach the outlet, and a bit more time to establish equilibrium (ie achieve steady state convergence). This convection process is often not well captured by the residuals. The best way to check that you have converged in this case is to add the imbalances as a convergence criteria. This is because the imbalances will pick this up as an imbalance in the AV. So you say the problem is converged - have you checked the imbalances? I suggest you have not converged yet and the imbalance for the AV equation will be poor.

 January 16, 2014, 06:06 #7 Member   Alireza Safikhani Join Date: Dec 2010 Posts: 36 Rep Power: 7 Dear Glenn Yes in fact the imbalance is poor, what should be done to have a good imbalance? Does AV is the abbreviation of Additional Variables or not? In fact I have simulated with initial value of mass fraction other than zero (for example 0.04) but this fault was still observed unfortunately. Regards

 January 16, 2014, 08:18 #8 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,704 Rep Power: 98 Poor imbalances means you have not converged yet. You need to run the simulation longer. By AV I mean additional variable. If your simulation is not converged (and poor imbalances means it is not converged) then do not worry about what it is giving for results. Until it is converged the results are rubbish.

 January 16, 2014, 09:16 #9 Member   Hamed Join Date: Oct 2009 Posts: 64 Rep Power: 9 Thank you very much glenn for very good guidance and sorry for consuming your time let me ask you the final question. In new simulations do you believe in that larger pseudo time should be used? How can I reach the pseudo time value and does the pseudo time the same as time scale ? now the time scale is set on " auto time scale" should I set the time scale on "Physical time scale" or "Local" time scale? How can I calculate the appropriate value of time scale? Regards

 January 16, 2014, 18:03 #10 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,704 Rep Power: 98 This is discussed in the documentation on obtaining convergence, and this FAQ: http://www.cfd-online.com/Wiki/Ansys...gence_criteria

 January 17, 2014, 00:27 #11 Member   Alireza Safikhani Join Date: Dec 2010 Posts: 36 Rep Power: 7 Thank you very much glenn for very good guidance, in fact I changed the time scale and the mass fraction shows very good distribution. Sincerely

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post charlotte CFX 4 March 22, 2011 10:14 ranjith CFX 3 October 15, 2010 09:50 Abby CFX 0 February 18, 2009 12:00 Ting Wen CFX 0 January 7, 2008 07:04 lego CFX 3 November 5, 2002 21:09

All times are GMT -4. The time now is 14:44.