Register Blogs Members List Search Today's Posts Mark Forums Read

May 27, 2014, 05:25
#1
New Member

Christoph
Join Date: May 2014
Posts: 10
Rep Power: 4
Hi,
I’m new in working with ANSYS CFX. I searched this forum for clarifying my issue but I did not find a real solution. So I will explain what I want to do.
I want to do a thermal analysis of a rough board in space. For the first approach I just want to irradiate this board from the sun in the distance of 1AU (sun-earth distance). The board should absorb this radiation in the solar spectrum and emit it in the infrared spectrum. I want to check this easy case of radiation modeling with the calculations I did by my own before I start with the harder simulation. The reason why I use CFX is because of directional radiation. I want to analyze the rough board later for hot spots due to reflections. That is not possible with the thermal steady-state analysis of ANSYS according to the support.
At first I want to create the surrounding area close to reality. Therefore I created a box for the vacuum (see attached picture). This domain is defined as a fluid with Air at 25 C (I switched to “false” for solving fluids). In this domain is my board, defined as a solid domain which is connected by a fluid-solid interface with the “vacuum”. My radiation flux at 1AU is about 1367 W/m^2. Therefore I defined a Radiation Source with a Directional Radiation Flux of the mentioned value at the boundary of the fluid domain. Additionally I fixed the temperature (3 K) of the walls of the fluid domain for the heat transfer and set the initial temperature of the board to 273 K. I am using Monte Carlo on both sides of the interface for thermal radiation. Solid and Fluid domain are participating medias. Do you think my definitions for the simulations are correct by now?
Here comes my real problem with CFX. As I said, I want to absorb and emit in different spectra. I have totally no idea how I can define this correctly in CFX!? I read something like the emissivity is derived by the absorption coefficient. So I tried to get this connection but I just found information about the “Einstein coefficients” which are not that easy to understand. Is there another possibility to define values like emissivity, absorptivity, transmittance and reflectivity or how should the absorption coefficient defined? I also read that for example the absorptivity is defined in CFX by “absorptivity= diffuse fraction* internal emissivity”. But the internal emissivity is not the same like you can define for the “Opaque” option. Maybe I have to work more on understanding thermal radiation or can you help me?!

So all in all my two questions are:
• Are my basic conditions correctly defined? If not, what should I change?
• Is it possible to define the mentioned values like emissivity, absorptivity and so on for my board (material: aluminum)? If yes, how ?

Best regards,
Chris

Edit: I forgot to post a part of the data from the output-file, sorry.

LIBRARY:
MATERIAL: Air at 25 C
Material Description = Air at 25 C and 1 atm (dry)
Material Group = Air Data, Constant Property Gases
Option = Pure Substance
Thermodynamic State = Gas
PROPERTIES:
Option = General Material
EQUATION OF STATE:
Density = 1.185 [kg m^-3]
Molar Mass = 28.96 [kg kmol^-1]
Option = Value
END
SPECIFIC HEAT CAPACITY:
Option = Value
Specific Heat Capacity = 1.0044E+03 [J kg^-1 K^-1]
Specific Heat Type = Constant Pressure
END
REFERENCE STATE:
Option = Specified Point
Reference Pressure = 1 [atm]
Reference Specific Enthalpy = 0. [J/kg]
Reference Specific Entropy = 0. [J/kg/K]
Reference Temperature = 25 [C]
END
DYNAMIC VISCOSITY:
Dynamic Viscosity = 1.831E-05 [kg m^-1 s^-1]
Option = Value
END
THERMAL CONDUCTIVITY:
Option = Value
Thermal Conductivity = 2.61E-02 [W m^-1 K^-1]
END
ABSORPTION COEFFICIENT:
Absorption Coefficient = 0.01 [m^-1]
Option = Value
END
SCATTERING COEFFICIENT:
Option = Value
Scattering Coefficient = 0.0 [m^-1]
END
REFRACTIVE INDEX:
Option = Value
Refractive Index = 1.0 [m m^-1]
END
THERMAL EXPANSIVITY:
Option = Value
Thermal Expansivity = 0.003356 [K^-1]
END
END
END
MATERIAL: Aluminium
Material Group = CHT Solids,Particle Solids
Option = Pure Substance
Thermodynamic State = Solid
PROPERTIES:
Option = General Material
EQUATION OF STATE:
Density = 2702 [kg m^-3]
Molar Mass = 26.98 [kg kmol^-1]
Option = Value
END
SPECIFIC HEAT CAPACITY:
Option = Value
Specific Heat Capacity = 9.03E+02 [J kg^-1 K^-1]
END
REFERENCE STATE:
Option = Specified Point
Reference Specific Enthalpy = 0 [J/kg]
Reference Specific Entropy = 0 [J/kg/K]
Reference Temperature = 25 [C]
END
THERMAL CONDUCTIVITY:
Option = Value
Thermal Conductivity = 237 [W m^-1 K^-1]
END
ABSORPTION COEFFICIENT:
Absorption Coefficient = 0.0001 [mm^-1]
Option = Value
END
END
END
END
FLOW: Flow Analysis 1
SOLUTION UNITS:
Length Units = [m]
Mass Units = [kg]
Solid Angle Units = [sr]
Temperature Units = [K]
Time Units = [s]
END
ANALYSIS TYPE:
EXTERNAL SOLVER COUPLING:
Option = None
END
END
DOMAIN: Platte
Coord Frame = Coord 0
Domain Type = Solid
Location = B18
BOUNDARY: Default Fluid Solid Interface Side 1 1
Boundary Type = INTERFACE
Location = F19.18,F20.18,F21.18,F22.18,F23.18,F24.18
BOUNDARY CONDITIONS:
HEAT TRANSFER:
Option = Conservative Interface Flux
END
Diffuse Fraction = 1.
Emissivity = 1.
Option = Opaque
END
END
END
DOMAIN MODELS:
DOMAIN MOTION:
Option = Stationary
END
MESH DEFORMATION:
Option = None
END
END
INITIALISATION:
Option = Automatic
INITIAL CONDITIONS:
Option = Automatic
END
TEMPERATURE:
Option = Automatic with Value
Temperature = 273 [K]
END
END
END
SOLID DEFINITION: Solid 1
Material = Aluminium
Option = Material Library
MORPHOLOGY:
Option = Continuous Solid
END
END
SOLID MODELS:
HEAT TRANSFER MODEL:
Option = Thermal Energy
END
Number of Histories = 100000
Option = Monte Carlo
Radiation Transfer Mode = Participating Media
SCATTERING MODEL:
Option = None
END
SPECTRAL MODEL:
Option = Gray
END
END
END
END
DOMAIN: Umgebung
Coord Frame = Coord 0
Domain Type = Fluid
Location = B57
BOUNDARY: Default Fluid Solid Interface Side 1
Boundary Type = INTERFACE
Location = F64.57,F65.57,F66.57,F67.57,F68.57,F69.57
BOUNDARY CONDITIONS:
HEAT TRANSFER:
Option = Conservative Interface Flux
END
MASS AND MOMENTUM:
Option = No Slip Wall
END
Diffuse Fraction = 0
Emissivity = 1.
Option = Opaque
END
END
END
BOUNDARY: Grenze
Boundary Type = WALL
Location = F58.57,F59.57,F60.57,F61.57,F62.57
BOUNDARY CONDITIONS:
HEAT TRANSFER:
Fixed Temperature = 3 [K]
Option = Fixed Temperature
END
MASS AND MOMENTUM:
Option = No Slip Wall
END
Diffuse Fraction = 0
Emissivity = 1.
Option = Opaque
END
END
END
BOUNDARY: Quelle
Boundary Type = WALL
Location = F63.57
BOUNDARY CONDITIONS:
HEAT TRANSFER:
Fixed Temperature = 3 [K]
Option = Fixed Temperature
END
MASS AND MOMENTUM:
Option = No Slip Wall
END
Diffuse Fraction = 0
Emissivity = 1.
Option = Opaque
END
END
BOUNDARY SOURCE:
SOURCES:
Radiation Flux = 1367 [W m^-2]
DIRECTION:
Option = Cartesian Components
Unit Vector X Component = 0
Unit Vector Y Component = 0
Unit Vector Z Component = -1
END
END
END
END
END
Attached Images

Last edited by Chris89; June 2, 2014 at 05:03. Reason: Data from Output-File

 June 2, 2014, 05:04 #2 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 And the rest: DOMAIN MODELS: BUOYANCY MODEL: Option = Non Buoyant END DOMAIN MOTION: Option = Stationary END MESH DEFORMATION: Option = None END REFERENCE PRESSURE: Reference Pressure = 1 [atm] END END FLUID DEFINITION: Fluid 1 Material = Air at 25 C Option = Material Library MORPHOLOGY: Option = Continuous Fluid END END FLUID MODELS: COMBUSTION MODEL: Option = None END HEAT TRANSFER MODEL: Option = Thermal Energy END THERMAL RADIATION MODEL: Number of Histories = 100000 Option = Monte Carlo Radiation Transfer Mode = Participating Media SCATTERING MODEL: Option = None END SPECTRAL MODEL: Option = Gray END END TURBULENCE MODEL: Option = Laminar END END INITIALISATION: Option = Automatic INITIAL CONDITIONS: Velocity Type = Cartesian CARTESIAN VELOCITY COMPONENTS: Option = Automatic END RADIATION INTENSITY: Option = Automatic END STATIC PRESSURE: Option = Automatic with Value Relative Pressure = 0 [Pa] END TEMPERATURE: Option = Automatic END END END END DOMAIN INTERFACE: Default Fluid Solid Interface Boundary List1 = Default Fluid Solid Interface Side 1 1 Boundary List2 = Default Fluid Solid Interface Side 1 Interface Type = Fluid Solid INTERFACE MODELS: Option = General Connection FRAME CHANGE: Option = None END HEAT TRANSFER: Option = Conservative Interface Flux HEAT TRANSFER INTERFACE MODEL: Option = None END END PITCH CHANGE: Option = None END THERMAL RADIATION: Option = Side Dependent END END MESH CONNECTION: Option = Automatic END END OUTPUT CONTROL: RESULTS: File Compression Level = Default Option = Standard END END SOLVER CONTROL: ADVECTION SCHEME: Option = High Resolution END CONVERGENCE CONTROL: Length Scale Option = Conservative Maximum Number of Iterations = 200 Minimum Number of Iterations = 10 Solid Timescale Control = Auto Timescale Timescale Control = Auto Timescale Timescale Factor = 1.0 END CONVERGENCE CRITERIA: Conservation Target = 0.01 Residual Target = 1.E-4 Residual Type = RMS END DYNAMIC MODEL CONTROL: Global Dynamic Model Control = On END THERMAL RADIATION CONTROL: Iteration Interval = 5 COARSENING CONTROL: Target Coarsening Rate = 4 END END END EXPERT PARAMETERS: solve fluids = f solve radiation = t END END COMMAND FILE: Version = 14.5 Results Version = 14.5.7 END SIMULATION CONTROL: EXECUTION CONTROL: EXECUTABLE SELECTION: Double Precision = On END INTERPOLATOR STEP CONTROL: Runtime Priority = Standard MEMORY CONTROL: Memory Allocation Factor = 1.0 END END PARALLEL HOST LIBRARY: HOST DEFINITION: ry000391 Remote Host Name = RY-000391 Host Architecture String = winnt-amd64 Installation Root = C:\Program Files\ANSYS1457\v%v\CFX END END PARTITIONER STEP CONTROL: Multidomain Option = Independent Partitioning Runtime Priority = Standard EXECUTABLE SELECTION: Use Large Problem Partitioner = Off END MEMORY CONTROL: Memory Allocation Factor = 1.0 END PARTITIONING TYPE: MeTiS Type = k-way Option = MeTiS Partition Size Rule = Automatic Partition Weight Factors = 0.50000, 0.50000 END END RUN DEFINITION: Run Mode = Full Solver Input File = Fluiddynamik CFX.def END SOLVER STEP CONTROL: Runtime Priority = Standard MEMORY CONTROL: Memory Allocation Factor = 1.0 END PARALLEL ENVIRONMENT: Number of Processes = 2 Start Method = Platform MPI Local Parallel Parallel Host List = ry000391*2 END END END END

 June 12, 2014, 07:52 #3 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 Update: I changed the boundary conditions of the vacuum to "openings" and set the opening pressure to 0 Pa and the opening temperature to 3 K. If I choose opaque for the domain interface with an emissivity of 1 I get the correct value for the temperature after adjusting the absorption coefficient. My problem regarding the absorptivity and emissivity is still present. For the first approach I know my ratio from the absorptivity to the emissivity. Therefore if I can set the emissivity to 1 I can multiply my incoming radiation flux with the ratio. That's ok for testing but because of the defined option opaque, the aluminum plate would not be considered. So I have to define also the reflectivity and transmissivity because I want to analyze a specimen with wrinkles. I already read the theory behind radiation modeling from ANSYS CFX but I have still no clue how CFX derives my desired values with the help of the absorption coefficient, scattering coefficient, the refractive index and the radiative transfer equation. Some radiation experts or non-radiation experts out there who can help me? Best regards, Chris P.S. Ordered "Thermal Radiation Heat Transfer" from Siegel and Howell. If I get the solution, I let you know. But if someone has an idea for the solution please post it .

 June 13, 2014, 20:38 #4 Senior Member   Join Date: Jun 2009 Posts: 573 Rep Power: 13 Below is sample CFX command language code on how to implement a spectral property for a thermal radiation model You can use 1D interpolation functions, or write your own expression with step functions (or logical CEL if you like as well). The main points are - Gather your spectral data - Decide how many spectral intervals you need - Create either expressions, or 1D-interp functions - Activate the multiband spectral model - Create as many spectral intervals you decided for this simulation - Use the expressions or function on the appropriate sections: emissivity at boundaries, absorption coefficients for materials, or even radiation fluxes at boundary sources (check with ANSYS support here for care on setting up spectral sources) Code: ``` LIBRARY: CEL : # # Example interpolation function for spectral property as a function of # frequency # FUNCTION: MatSpectralAbsorption Argument Units = [s^-1] Option = Interpolation Result Units = [m^-1] INTERPOLATION DATA: Data Pairs = \ 3e+013 , 0.98, \ 4.25e+013, 0.98, \ 4.26e+013, 0.7, \ 4.99e+013, 0.7, \ 5e+013 , 0.29,\ 5.99e+013, 0.29, \ 6e+013 , 0.08, \ 3e+014 , 0.08 Extend Max = On Extend Min = On Option = One Dimensional END END # # Example using expressions with step function # EXPRESSIONS : # # Limit for the wavelength intervals of interest # WavlLow = 1.E-02 [micron] Wavl1 = 4.E-01 [micron] Wavl2 = 7.E-01 [micron] Wavl3 = 1.E+02 [micron] WavlHigh = 1.E+10 [micron] # # Dimensionless wavelength variables, including CEL wavelo # wavlLow = WavlLow * 1[m^-1] wavl1 = Wavl1 * 1[m^-1] wavl2 = Wavl2 * 1[m^-1] wavl3 = Wavl3 * 1[m^-1] wavl4 = Wavl4 * 1[m^-1] wavl5 = Wavl5 * 1[m^-1] wavlHigh = WavlHigh * 1[m^-1] wavldim = wavelo * 1[m^-1] # # Interpolation weights to describe spectral property as a function of # wavelegth # int1 = step(wavl1 -wavldim) int2 = (step(wavl2 -wavldim)-step(wavl1-wavldim)) int3 = (step(wavl3 -wavldim)-step(wavl2-wavldim)) int4 = (step(wavlHigh-wavldim)-step(wavl3-wavldim)) # # Values of spectral property on each interval # prop1 = ... prop2 = ... prop3 = ... prop4 = ... # SpectralProp = (prop1 * int1 + prop2 * int2 + \ prop3 * int3 + prop3 * int4) END END THERMAL RADIATION MODEL: ... SPECTRAL MODEL: Option = Multiband SPECTRAL BAND: UV Option = Wavelength in Vacuum Wavelength Lower Limit = WavlLow Wavelength Upper Limit = Wavl1 END SPECTRAL BAND: Visible Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl1 Wavelength Upper Limit = Wavl2 END SPECTRAL BAND: Thermal Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl2 Wavelength Upper Limit = Wavl3 END SPECTRAL BAND: Microwave Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl3 Wavelength Upper Limit = WavlHigh END END ... END # # Usage for emissivity # THERMAL RADIATION: Option = Opaque Emissivity = SpectralProp Diffuse Fraction = ... END # # Usage for absorption coefficient of material # MATERIAL: ... PROPERTIES: ABSORPTION COEFFICIENT: Absorption Coefficient = MatSpectralAbsorption(freq) Option = Value END END END``` Hope the above helps, asb962, Chris89 and Lemanes like this.

 June 14, 2014, 09:39 #5 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 Hi Opaque, Thank you very much for the response. I will implement the code and adjust it to my purposes. I think this definition will work for the different spectra in absorption and emission. But unfortunately I am still confused regarding the relation between the absorption coefficient with the absorptivity, reflectivity and transmissivity . But I will work on this problem until I got it or one of you can explain this correlation . Regards, Chris

 June 14, 2014, 10:58 #6 Senior Member   Join Date: Jun 2009 Posts: 573 Rep Power: 13 Another good book to read is Radiative Heat Transfer by Michael Modest. I think the 3rd edition is the most recent. The vocabulary used in the radiation literature varies greatly between areas of application, and groups. Many times you must understand the meaning from the context. Overall, you can assume all media absorb, emit and scatter radiative energy. Some media absorbs so much in a very short length that there is no point to model the volumetric effects, and they can be reduced to surface effects. One you are modeling them as surfaces, the interaction at surfaces are split into 2 types: self, and external. Self is emission, external is what happens to the incoming energy: reflected, absorbed, or transmitted. The last 3 must add up to the total incoming amount; therefore, their relative contribution can be represented as fractions: absortptiv-ity(tance or alpha), reflect-ivity(ance or rho), and transmit-ivity(ance or tau). They are not independent, and usually you only need to 1 of them: - Opaque : tau = 0, rho = 1 - alpha - Semi-transparent: alpha = 0, rho = 1 - tau - Mirror: tau = 1, rho = alpha = 0 - Black : alpha = 1, rho = 0, tau = 0 For practical applications, the surface "properties" (no such a thing since they depend on surface quality as well as material) can be found on handbook, technical literature, or material providers. The relation between the 3 above, and emissivity is only simple for the monochromatic (or spectral) case, where by Kirchoff law emissivity = absorptivity. Once the spectral approximations (such a gray) are used, their relationship is not straightforward, but for rough estimates you can just assume Kirchoff law always applies, and refine your approximation if needed. When talking about non-gray (or spectral) modeling, there has been the tendency to use the word emittance for volumetric effects (which definitely depends on the absorption coefficient and other thermodynamic variables), but it is not the same as emissivity at a surface. Hope the above helps,

 June 15, 2014, 10:30 #7 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 Thank you again for your detailed reply . Ok, so in my case I think the definition of an opaque boundary should fit because the transmissivity is negligible. But because this simulaion is for a space application with an absorptivity in the solar spectrum and an emissivity in the infrared spectrum it is unfortunately not possible for me to assume Kirchhoff's law of thermal radiation is valid. I assume for the transfer mode "surface to surface" CFX calculates the solution with absorptivity=emissivity without any other specifications in the settings!? Therefore I think I have to work on the spectral approximation. Thank you for the recommendation of the book. If the ordered book, which hopefully will be delivered next week, does not solve the problem I will order Radiative Heat Transfer . Best regards

 June 19, 2014, 11:15 #8 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 Now I solved the problem with the help of your advices Opaque. Special thanks to you!! Here the important informations of the output file for those who want to do the same. Code: ``` LIBRARY: CEL: EXPRESSIONS: SpectralProp = (prop1 * int1 + prop2 * int2 + prop3 * int3 + prop3 * \ int4) Wavl1 = 4.E-01 [micron] Wavl2 = 7.E-01 [micron] Wavl3 = 1.E+02 [micron] WavlHigh = 1.E+10 [micron] WavlLow = 1.E-02 [micron] flux3 = (rad1*int1+rad2*int2+rad3*int3+rad4*int4) int1 = step(wavl1 -wavldim) int2 = (step(wavl2 -wavldim)-step(wavl1-wavldim)) int3 = (step(wavl3 -wavldim)-step(wavl2-wavldim)) int4 = (step(wavlHigh-wavldim)-step(wavl3-wavldim)) prop1 = 0 prop2 = 0.093 prop3 = 0.015 rad1 = 0 [W/m^2] rad2 = 1367 [W/m^2] rad3 = 350 [W/m^2] rad4 = 0 [W/m^2] wavl1 = Wavl1*1[m^-1] wavl2 = Wavl2*1[m^-1] wavl3 = Wavl3*1[m^-1] wavlHigh = WavlHigh*1[m^-1] wavlLow = WavlLow*1[m^-1] wavldim = wavelo*1[m^-1] END END MATERIAL: Air at 25 C Material Description = Air at 25 C and 1 atm (dry) Material Group = Air Data, Constant Property Gases Option = Pure Substance Thermodynamic State = Gas PROPERTIES: Option = General Material EQUATION OF STATE: Density = 1.185 [kg m^-3] Molar Mass = 28.96 [kg kmol^-1] Option = Value END SPECIFIC HEAT CAPACITY: Option = Value Specific Heat Capacity = 1.0044E+03 [J kg^-1 K^-1] Specific Heat Type = Constant Pressure END REFERENCE STATE: Option = Specified Point Reference Pressure = 1 [atm] Reference Specific Enthalpy = 0. [J/kg] Reference Specific Entropy = 0. [J/kg/K] Reference Temperature = 25 [C] END DYNAMIC VISCOSITY: Dynamic Viscosity = 1.831E-05 [kg m^-1 s^-1] Option = Value END THERMAL CONDUCTIVITY: Option = Value Thermal Conductivity = 2.61E-02 [W m^-1 K^-1] END ABSORPTION COEFFICIENT: Absorption Coefficient = 0.01 [m^-1] Option = Value END SCATTERING COEFFICIENT: Option = Value Scattering Coefficient = 0.0 [m^-1] END REFRACTIVE INDEX: Option = Value Refractive Index = 1.0 [m m^-1] END THERMAL EXPANSIVITY: Option = Value Thermal Expansivity = 0.003356 [K^-1] END END END MATERIAL: Aluminium Material Group = CHT Solids,Particle Solids Option = Pure Substance Thermodynamic State = Solid PROPERTIES: Option = General Material EQUATION OF STATE: Density = 2702 [kg m^-3] Molar Mass = 26.98 [kg kmol^-1] Option = Value END SPECIFIC HEAT CAPACITY: Option = Value Specific Heat Capacity = 9.03E+02 [J kg^-1 K^-1] END REFERENCE STATE: Option = Specified Point Reference Specific Enthalpy = 0 [J/kg] Reference Specific Entropy = 0 [J/kg/K] Reference Temperature = 25 [C] END THERMAL CONDUCTIVITY: Option = Value Thermal Conductivity = 237 [W m^-1 K^-1] END END END MATERIAL: Polyimide Material Group = User Option = Pure Substance Thermodynamic State = Solid PROPERTIES: Option = General Material EQUATION OF STATE: Density = 1.42 [g cm^-3] Molar Mass = 34000 [g mol^-1] Option = Value END SPECIFIC HEAT CAPACITY: Option = Value Specific Heat Capacity = 1090 [J kg^-1 K^-1] END THERMAL CONDUCTIVITY: Option = Value Thermal Conductivity = 225 [W m^-1 K^-1] END END END END FLOW: Flow Analysis 1 SOLUTION UNITS: Angle Units = [rad] Length Units = [m] Mass Units = [kg] Solid Angle Units = [sr] Temperature Units = [K] Time Units = [s] END ANALYSIS TYPE: Option = Steady State EXTERNAL SOLVER COUPLING: Option = None END END DOMAIN: Platte Coord Frame = Coord 0 Domain Type = Solid Location = B276 BOUNDARY: Bestrahlte_Flaeche_Vakuum Side 2 Boundary Type = INTERFACE Location = F279.276,F280.276,F281.276,F282.276,F283.276,F284.276 BOUNDARY CONDITIONS: HEAT TRANSFER: Option = Conservative Interface Flux END END END DOMAIN MODELS: DOMAIN MOTION: Option = Stationary END MESH DEFORMATION: Option = None END END SOLID DEFINITION: Solid 1 Material = Polyimide Option = Material Library MORPHOLOGY: Option = Continuous Solid END END SOLID MODELS: HEAT TRANSFER MODEL: Option = Thermal Energy END THERMAL RADIATION MODEL: Number of Histories = 10000 Option = Monte Carlo Radiation Transfer Mode = Surface to Surface SCATTERING MODEL: Option = None END SPECTRAL MODEL: Option = Multiband SPECTRAL BAND: Microwave Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl3 Wavelength Upper Limit = WavlHigh END SPECTRAL BAND: Thermal Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl2 Wavelength Upper Limit = Wavl3 END SPECTRAL BAND: UV Option = Wavelength in Vacuum Wavelength Lower Limit = WavlLow Wavelength Upper Limit = Wavl1 END SPECTRAL BAND: Visible Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl1 Wavelength Upper Limit = Wavl2 END END END END END DOMAIN: Umgebung Coord Frame = Coord 0 Domain Type = Fluid Location = B103 BOUNDARY: Bestrahlte_Flaeche_Vakuum Side 1 Boundary Type = INTERFACE Location = F218.103,F219.103,F220.103,F221.103,F222.103,F223.103 BOUNDARY CONDITIONS: HEAT TRANSFER: Option = Conservative Interface Flux END MASS AND MOMENTUM: Option = No Slip Wall END END END BOUNDARY: Grenze Boundary Type = OPENING Location = F106.103,F107.103,F108.103,F109.103,F231.103 BOUNDARY CONDITIONS: FLOW REGIME: Option = Subsonic END HEAT TRANSFER: Opening Temperature = 3 [K] Option = Opening Temperature END MASS AND MOMENTUM: Option = Entrainment Relative Pressure = 0 [Pa] PRESSURE OPTION: Option = Opening Pressure END END THERMAL RADIATION: Option = Local Temperature END END END BOUNDARY: Strahlung Boundary Type = OPENING Location = F230.103 BOUNDARY CONDITIONS: FLOW REGIME: Option = Subsonic END HEAT TRANSFER: Opening Temperature = 3 [K] Option = Opening Temperature END MASS AND MOMENTUM: Option = Entrainment Relative Pressure = 0 [Pa] PRESSURE OPTION: Option = Opening Pressure END END THERMAL RADIATION: Option = Local Temperature END END BOUNDARY SOURCE: SOURCES: RADIATION SOURCE: Radiation Source 1 Option = Directional Radiation Flux Radiation Flux = flux3 DIRECTION: Option = Cartesian Components Unit Vector X Component = 0 Unit Vector Y Component = 0 Unit Vector Z Component = 1 END END END END END DOMAIN MODELS: BUOYANCY MODEL: Option = Non Buoyant END DOMAIN MOTION: Option = Stationary END MESH DEFORMATION: Option = None END REFERENCE PRESSURE: Reference Pressure = 1 [atm] END END FLUID DEFINITION: Fluid 1 Material = Air at 25 C Option = Material Library MORPHOLOGY: Option = Continuous Fluid END END FLUID MODELS: COMBUSTION MODEL: Option = None END HEAT TRANSFER MODEL: Option = Thermal Energy END THERMAL RADIATION MODEL: Number of Histories = 10000 Option = Monte Carlo Radiation Transfer Mode = Surface to Surface SCATTERING MODEL: Option = None END SPECTRAL MODEL: Option = Multiband SPECTRAL BAND: Microwave Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl3 Wavelength Upper Limit = WavlHigh END SPECTRAL BAND: Thermal Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl2 Wavelength Upper Limit = Wavl3 END SPECTRAL BAND: UV Option = Wavelength in Vacuum Wavelength Lower Limit = WavlLow Wavelength Upper Limit = Wavl1 END SPECTRAL BAND: Visible Option = Wavelength in Vacuum Wavelength Lower Limit = Wavl1 Wavelength Upper Limit = Wavl2 END END END TURBULENCE MODEL: Option = Laminar END END END DOMAIN INTERFACE: Bestrahlte_Flaeche_Vakuum Boundary List1 = Bestrahlte_Flaeche_Vakuum Side 1 Boundary List2 = Bestrahlte_Flaeche_Vakuum Side 2 Interface Type = Fluid Solid INTERFACE MODELS: Option = General Connection FRAME CHANGE: Option = None END HEAT TRANSFER: Option = Conservative Interface Flux HEAT TRANSFER INTERFACE MODEL: Option = None END END PITCH CHANGE: Option = None END THERMAL RADIATION: Diffuse Fraction = 0 Emissivity = SpectralProp Option = Opaque END END MESH CONNECTION: Option = GGI END END OUTPUT CONTROL: RESULTS: File Compression Level = Default Option = Standard END END SOLVER CONTROL: ADVECTION SCHEME: Option = High Resolution END CONVERGENCE CONTROL: Length Scale Option = Aggressive Maximum Number of Iterations = 2000 Minimum Number of Iterations = 10 Solid Timescale Control = Auto Timescale Solid Timescale Factor = 2 Timescale Control = Auto Timescale Timescale Factor = 1.5 END CONVERGENCE CRITERIA: Conservation Target = 0.01 Residual Target = 1.E-4 Residual Type = RMS END DYNAMIC MODEL CONTROL: Global Dynamic Model Control = On END EQUATION CLASS: energy CONVERGENCE CONTROL: Length Scale Option = Aggressive Timescale Control = Auto Timescale Timescale Factor = 1.5 END CONVERGENCE CRITERIA: Conservation Target = 0.01 Residual Target = 1.0E-4 Residual Type = RMS END END THERMAL RADIATION CONTROL: Iteration Interval = 5 COARSENING CONTROL: Target Coarsening Rate = 4 END END END EXPERT PARAMETERS: solve fluids = f solve radiation = t END END COMMAND FILE: Version = 14.5 Results Version = 14.5.7 END SIMULATION CONTROL: EXECUTION CONTROL: EXECUTABLE SELECTION: Double Precision = On END INTERPOLATOR STEP CONTROL: Runtime Priority = Standard MEMORY CONTROL: Memory Allocation Factor = 1.0 END END PARALLEL HOST LIBRARY: HOST DEFINITION: ry000391 Remote Host Name = RY-000391 Host Architecture String = winnt-amd64 Installation Root = C:\Program Files\ANSYS1457\v%v\CFX END END PARTITIONER STEP CONTROL: Multidomain Option = Independent Partitioning Runtime Priority = Standard EXECUTABLE SELECTION: Use Large Problem Partitioner = Off END MEMORY CONTROL: Memory Allocation Factor = 1.0 END PARTITIONING TYPE: MeTiS Type = k-way Option = MeTiS Partition Size Rule = Automatic Partition Weight Factors = 0.50000, 0.50000 END END RUN DEFINITION: Run Mode = Full Solver Input File = Fluiddynamik CFX.def END SOLVER STEP CONTROL: Runtime Priority = Standard MEMORY CONTROL: Memory Allocation Factor = 1.0 END PARALLEL ENVIRONMENT: Number of Processes = 2 Start Method = Platform MPI Local Parallel Parallel Host List = ry000391*2 END END END END``` I have just one more question . I would like to visualize the rays which will be reflected. Is that possible in CFD-Post? Particle tracking is possible and maybe also ray tracking? I have to use Monte Carlo, so ray tracing with the DTM would not be possible. Are radiometers possible to visualize adequate the rays? Best regards, Chris

 June 19, 2014, 13:12 #9 Senior Member   Join Date: Jun 2009 Posts: 573 Rep Power: 13 Glad to hear you made it work.. Unfortunately, the rays used for the radiation modeling cannot be visualized at all. You can visualize rays for a radiometer though by setting the Diagnostic Output level to a value larger than 0. A .csv file will be written for every radiometer with diagnostic output level greater than 0. Such file contain the rays leaving a radiometer including their reflections (so you can track the original source of the ray). To visualize the rays, you create a polyline in CFD-Post, select the option From File, and apply. If I recall correctly, a diagnostic output of 1 gives a single .csv file. For value of 2, you can get a .csv per time step. For non-deforming meshes or non-conditional domain interfaces, those .csv files will be the same. so you can just 1. Hope the above helps,

 June 19, 2014, 17:06 #10 New Member   HH Join Date: Apr 2014 Posts: 12 Rep Power: 4 Could you please tell me how I can model pure radiation without convection or conduction in the domain? I want to model radiation in vacuum.

 June 19, 2014, 18:49 #11 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 Use the expert parameters to turn the flow solver and any other solvers you do not want off.

 June 19, 2014, 19:05 #12 New Member   HH Join Date: Apr 2014 Posts: 12 Rep Power: 4 Thanks for your response. In my problem, I have different solids and fluid domains and I have to solve energy and fluid equation in them except one of them which I want to solve only radiation heat transfer. Therefore, if I turn off the flow and energy equations from expert parameters, the energy and flow will not solve in other domains.

 June 21, 2014, 05:54 #13 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 Then I would make your vacuum a solid domain, and use a solid with a very low (but not zero) conductivity.

 June 21, 2014, 14:46 #14 New Member   HH Join Date: Apr 2014 Posts: 12 Rep Power: 4 Thank you very much ghorrocks.

 August 13, 2014, 07:17 #15 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 Hello again , I have a further question regarding the radiation modeling. I want to analyze a surface with a wrinkle in vacuum. Nearly the same conditions and properties as for the last simulation (surface to surface, Monte Carlo method, different spectra for absorption and emission, interface between the surface and the vacuum). Since the incoming directional radiation flux reflects, hot spots should occur. The problem is the definition of the vacuum and therefore the convergence. If the fluid solver will be turned off, the surface of the vacuum for the interface has still the properties of the fluid and therefore the conductivity, which leads to wrong results. For these settings, the solver converges. If I create another “material” for the vacuum with low conductivity, low density and high viscosity as ghorrocks recommended in another thread regarding the vacuum definition, the results after 300 iterations (about 3 hours) seem to be correct but the solver does not converges. Is there a possibility to adjust the convergence criteria for the low conductivity or is there another possibility for the definition of a vacuum in CFX? Is CFX generally suitable for such radiation problems with a vacuum? Best regards, Chris

 August 13, 2014, 18:44 #16 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 No, my recommendation for your vacuum material is to make it a solid domain. Then you do not need to worry about any fluid properties. Also low conductivity is required, but high density might be more numerically stable.

 August 14, 2014, 04:42 #17 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 Thank you for your reply! I tried this option for the vacuum definition, too. The problem is the definition of the surfaces of the vacuum domain. I have to set an emissivity and either the surfaces absorb and emit the irradiation from the wrinkle surface for a value of "1" or they reflect the incoming energy, which comes from the wrinkle surface. This leads unfortunately also to wrong results for the temperature distribution due to the radiation from the surrounding "surfaces" of the vacuum.

 August 14, 2014, 06:39 #18 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 I have no idea what you are talking about. I am not an expert on radiation modelling but my understanding is that the same options are available for a solid domain as for a fluid domain. So whatever radiation boundary conditions you defined for the fluid domain can be set for the solid domain. So whatever settings you have put on the fluid domain you can put them on the solid domain as well.

 August 14, 2014, 07:01 #19 New Member   Christoph Join Date: May 2014 Posts: 10 Rep Power: 4 If I define the vacuum as a solid domain, I can either choose wall or symmetry for the boundaries. For a wall, I have to set an emissivity which leads to the mentioned problems. If I define the vacuum as a fluid domain, I can define the boundaries as openings and therefore no radiation will be absorbed, reflected or emitted, only transmitted. That is what I want but it is not possible for a solid domain. Or is there any possibility to define a transmissivity of 100% for a surface of a solid domain?

 August 14, 2014, 07:33 #20 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 Can you use a solid domain with wall boundaries where the temperature of the wall is set to almost absolute zero (like 1 [K])? Then the wall will absorb radiation but not radiate or reflect.

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post mirko OpenFOAM Programming & Development 7 May 20, 2016 08:31 s.mishra ANSYS 0 March 31, 2012 04:12 cloudnqh FLUENT 6 February 15, 2010 10:06 Kaushik Saha FLUENT 0 September 17, 2008 19:12 Klaus-Peter Helbig Main CFD Forum 3 October 25, 1999 02:40

All times are GMT -4. The time now is 21:01.