# Heat conduction in a solid domain

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 September 18, 2003, 06:22 Heat conduction in a solid domain #1 S. Balasubramanyam Guest   Posts: n/a Hi, I am trying to solve a simple heat conduction problem using CFX5.6. I am getting an error message which says that there is no fluid domain. I have just taken a plate which has one hot face and 5 adiabatic faces with lower initial temperature. There is no fluid domain in the problem. Is it necessary that we must have a fluid domain in each problem? I request anyone who used CFX, to help me in understanding, how to handle CFX5.6 to solve this problem. Thanks in advance.

 September 18, 2003, 11:01 Re: Heat conduction in a solid domain #2 Robin Guest   Posts: n/a Yes, just setup a fluid domain as normal but: 1. Set your velocity initial guess to zero, 2. Set your advection scheme to upwind to avoid vertex gradient calculations, 3. Set the expert parameter "solve fluids = f" to turn of the hydro equations, 4. Set the turbulence model to laminar. You can also do all this and include CHT solids if you have more than one solid domain. Regards, Robin

 September 26, 2003, 04:52 Re: Heat conduction in a solid domain #3 Märta-Karin Guest   Posts: n/a Hi Robin I am trying to model the cooling of a warm ring by a gas flow and I would like to get the temperature field inside the ring. But when I run the transient simulation the temperature field inside the ring is constant which it should not be. Do you have an idea of what is wrong ? Thanks a lot. Märta

 September 26, 2003, 16:12 Re: Heat conduction in a solid domain #4 Robin Guest   Posts: n/a Hi Märta, Transient CHT simulations are really quite impractical because the timescale of the fluid dynamics is significantly shorter than that of the heat transfer through the solid. The temperature in your solid probably isn't constant, it is just changing so slowly that you are not seeing it. If you don't expect the flowfield to change much, you could freeze the momentum equations (set expert parameter 'solve fluids = f' and use a much larger timestep. This would then solve the heat transfer and transport in the fluid, but the flowfield would remain fixed. If you do expect the flowfield to change significantly, I recommend finding yourself a good novel, as you may have to wait a while Note that in a steady state simulation you would typically use a timestep 10x or 100x larger for your solid than your fluid, and you are already using a significantly larger timestep than required for a transient simulation. Regards, Robin

 September 29, 2003, 03:49 Re: Heat conduction in a solid domain #5 Märta-Karin Guest   Posts: n/a Hi Robin! Thanks for your answer, it was very helpful and quite correct about the temperature changes. I have another idea about how to make the solution go faster - I want to calculate the solution in steady state and then interpolate the solution on the gtm file I use for the transient runs. Though, this means that the mesh in the steady state and the transient have to be exactly the same, and I can't find out how to set the boundaries on the ring in the steady state case in order to keep the ring temperature constant. Do you know how to set the ring to one temperature? It seems to me as it is not possible to use domain interfaces in this case. Best Regards, Märta-Karin

 October 10, 2003, 13:52 Re: Heat conduction in a solid domain #6 Amit Katiyar Guest   Posts: n/a Hi Robin, I am also solving a similar problem S. Balasubramanyam. I followed your suggestions but i am having error as:<< There are domain location parameters that have been used more than once in this problem.>> This is because i have only one domain in my geometry. So please guide in this context. thanks amit

 October 10, 2003, 16:03 Re: Heat conduction in a solid domain #7 Robin Guest   Posts: n/a Hi Amit, You are probably referencing the same region for two boundary conditions. Robin

 October 10, 2003, 17:34 Re: Heat conduction in a solid domain #8 Amit Katiyar Guest   Posts: n/a hi Robin, Thanks for replying. Actually I will have to refer same domain for both because I have only one 3-D domain in my geometry. My geometry is solid cube having bottom at 500 K and all other surfaces at 300 K and I want to see heat transfered by conduction. So Guide me. Amit

 October 11, 2003, 13:36 Re: Heat conduction in a solid domain #9 Amit Katiyar Guest   Posts: n/a Dear experts, Please tell me the difference between static temperature and total temperature. I found them while specifying opening boundary conditions. Thanks. Amit

 October 12, 2003, 05:11 guide me #10 Amit Katiyar Guest   Posts: n/a Dear experts, Please tell me the difference between static temperature and total temperature. I found them while specifying opening boundary conditions. Thanks. Amit

 October 14, 2003, 08:57 Re: guide me #11 Robin Guest   Posts: n/a Hi Amit, The static temperature is that which you would get if you measured the temperature of the moving fluid. The total temperature is the temperature you would measure if the fluid was decelerated isentropically to zero velocity (relative to the reference frame), such as at a stagnation point (sometimes referred to as the stagnation temperature). Regards, Robin

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post swahono OpenFOAM Running, Solving & CFD 8 February 26, 2015 05:30 B.Simon CFX 3 October 28, 2008 19:53 Rogerio Fernandes Brito CD-adapco 0 March 18, 2008 18:23 Ken Adams FLUENT 5 January 18, 2007 19:14 Chie Min CFX 5 July 12, 2001 23:19

All times are GMT -4. The time now is 19:27.

 Contact Us - CFD Online - Top