visualize the initial and/or boundary conditions

 Register Blogs Members List Search Today's Posts Mark Forums Read

 April 28, 2004, 10:10 visualize the initial and/or boundary conditions #1 pi Guest   Posts: n/a Dear all, IŽd useful any trick to visualize in post the initial conditions or the BC. In complex geometries it is easy to make mistakes or do not set the right (physically right)ones in corners, for example. How do you do it(if you do)? thanks pi

 April 28, 2004, 12:15 Re: visualize the initial and/or boundary conditio #2 Gloria Gaynor Guest   Posts: n/a Try to set the following expert parameters: solve fluids = f solve tke eps = f This will turn off the equation solver (assuming you're using k-epsilon model). Run for 1 iteration only and you'll be able to see your initial conditions. Take a look at the CFX-5/etc/5.6/RULES file and you'll find the suitable expert parameters to turn off the equations for your specific case. Good luck, G. G.

 April 28, 2004, 18:26 Re: visualize the initial and/or boundary conditio #3 Glenn Horrocks Guest   Posts: n/a Hi, There are other ways of doing it which do not require you to do a dummy simulation. For steady state runs you can, just after starting a run press "Backup Run"; or in CFX-Pre you can set it up to output the initial conditions with output control/backup results and set the iteration list to 0. For transient runs, in CFX-Pre use Output Control/Transient Results, and set the time list to zero. Regards, Glenn

 April 29, 2004, 00:03 Re: visualize the initial and/or boundary conditio #4 test Guest   Posts: n/a To visualize the initial condition for a steady state run use the following expert parameter: backup file at zero =t This will create a backup file at 0th iteration! ie before the start of the solution so that you can view the initial guess. IN cfx-5.7 you can visualize the boundary conditions in Pre itself.. I have not tested out the same for initial conditions!

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post cyberbrain OpenFOAM 4 March 16, 2011 10:20 renyun0511 OpenFOAM Running, Solving & CFD 0 November 19, 2009 03:11 sunnysun OpenFOAM Running, Solving & CFD 5 March 16, 2009 04:32 david OpenFOAM Running, Solving & CFD 36 October 21, 2008 21:55 sivakumar OpenFOAM Pre-Processing 9 September 9, 2008 12:53

All times are GMT -4. The time now is 23:30.