CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Reference density in buoyant multiphase-flow?

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   February 8, 2005, 05:03
Default Reference density in buoyant multiphase-flow?
  #1
Johannes Radke
Guest
 
Posts: n/a
Hi everybody,

I am simulating a buoyant two-phase flow (air, water) through a packed column in CFX 5.7. Both phases are continuous. Which value has the reference density?

In the manual I read something about an average-density in the domain. One of my friends told me to set the density of the heavier fluid as reference density.

I hope that somebody can help me on this question.

Thanks in advance and best regards, Johannes
  Reply With Quote

Old   February 8, 2005, 11:50
Default Re: Reference density in buoyant multiphase-flow?
  #2
Neser
Guest
 
Posts: n/a
Hi, Johannes

set the buoyancy reference density to that of the contiuous phase.

I think that in your case it is the air.

regards
  Reply With Quote

Old   February 8, 2005, 13:33
Default Re: Reference density in buoyant multiphase-flow?
  #3
Johannes Radke
Guest
 
Posts: n/a
I my case both fluids are continuous-phases, as written above.

Regards, Johannes

  Reply With Quote

Old   February 9, 2005, 01:13
Default Re: Reference density in buoyant multiphase-flow?
  #4
Erica
Guest
 
Posts: n/a
in your case, you can set the density of air as the buoyance reference. you can see the hydrostatic pressure distribution of water as it refer in the cfx manual BR Erica
  Reply With Quote

Old   February 9, 2005, 11:19
Default Re: Reference density in buoyant multiphase-flow?
  #5
Johannes Radke
Guest
 
Posts: n/a
Ok, thanks for your help, Erica.

Johannes
  Reply With Quote

Old   February 10, 2005, 05:00
Default Re: Reference density in buoyant multiphase-flow?
  #6
Johannes Radke
Guest
 
Posts: n/a
I read the cfx manual about the hydrostatic pressure gradient. There is written:

p_hydrostat = rho_ref * gravity * (r - r_ref)

If I use the density of air as the reference density I will not see any hydrostatic pressure gradient caused by the water column. I will just see the gradient caused by the air. Or am I wrong?

Regards, Johannes
  Reply With Quote

Old   February 11, 2005, 00:43
Default Re: Reference density in buoyant multiphase-flow?
  #7
Erica
Guest
 
Posts: n/a
In your case, two phases are continuous one, you should set the light phase as reference one. It will cancel the buoyant force and hydrostatic pressure of the reference phase. In order to decrease the roundoff error,you should choose the lighter one as reference phase.

BR, Erica
  Reply With Quote

Old   February 11, 2005, 05:52
Default Re: Reference density in buoyant multiphase-flow?
  #8
Johannes Radke
Guest
 
Posts: n/a
I have one more question: With air as reference phase, will I see any hydrostatic-pressure gradient caused by the water phase in the result-file? And if yes, in the pressure or in the absolut-pressure distribution?

Regards, Johannes
  Reply With Quote

Old   February 11, 2005, 20:40
Default Re: Reference density in buoyant multiphase-flow?
  #9
Erica
Guest
 
Posts: n/a
Yes, you can it in the result file.It is pressure. You can see it in cfx-post.

BR, Erica
  Reply With Quote

Old   February 13, 2005, 01:40
Default Re: Reference density in buoyant multiphase-flow?
  #10
Jeff
Guest
 
Posts: n/a
Johannes,

Using the air density as the refernce density, you'll get body force in the air phase which is:

B = g * ( rho.air - rho.ref ) = 0

In the water phase, the body force will be:

B = g * ( rho.water - rho.ref )

Since rho.water is ~1000, and rho.ref = rho.air = ~1, this will give the hydrostatic force in the liquid phase. You should see the expected hydrostatic pressure. Note both phases share the same pressure.

I have had stability issues with this setting when bubbling a gas through a liquid tank and setting the liquid phase density as the reference density gave a more stable convergence (not sure why yet). In this case, the body force on the liquid (my continuous phase) is subtracted out, however it gives the correct flow solution. In this case, you can adjust the pressure in Post by adding the hydrostatic head back in to create a new variable and plot that instead of pressure.

Not sure what your continuous/continuous case will do.

Jeff
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Water subcooled boiling Attesz CFX 7 January 5, 2013 04:32
OpenFoam 1.6-ext - RPM build errors preibie OpenFOAM 12 September 8, 2011 03:12
Multiphase flow in atomiser santhosh1987 FLUENT 0 May 12, 2011 04:26
Simulation of a single bubble with a VOF-method Suzzn CFX 18 October 2, 2009 04:18
Multiphase flow for flow around ship gundul CFX 5 September 2, 2008 16:06


All times are GMT -4. The time now is 12:27.