# flow in pipe with momentum and energy source

 Register Blogs Members List Search Today's Posts Mark Forums Read

 March 27, 2005, 12:43 flow in pipe with momentum and energy source #1 Atit Koonsrisuk Guest   Posts: n/a I try to model the thing so-called actuator disc. It is the approximation of turbine. The actuator disc is very thin such that flow field properties change discontinuously across it. Then I test the concept by model the flow of water in circular pipe. I set the boundary condition at pipe inlet as 'inlet' with velocity specified, and at pipe exit as 'outlet' with zero relative static pressure. In addition, I create the fluid sub-domain within the pipe, this sub-domain is the actuator disc. The ratio of thinkness to diameter of sub-domain is 0.0125, and I use mesh control with 1.2 expansion factor to make the finer grid in sub-domain. I set this sub-domain as the energy source and momentum source simultaneously. The energy source is (-dW/volume) and the energy source is (-dW/(volume x velocity)), where dW is the power that I want the actuator disc to extract from the flow, and 'volume' is the volume of sub-domain. The result seems reasonable. The difference between velocity before actuator disc and velocity after actuator disc is only 0.04%. In addition, the difference of total enthalpy before and after actuator disc is about 'dW'. So I'm pretty sure that I understand how to model actuator disc in CFX. However one thing that I do not understand from the result is that the change of velocity inside the sub-domain. The velocity inside the actuator disc is fluctuated, and the maximum value is 163% of the velocity before actuator disc, whereas the pressure is not fluctuated. Do anyone have idea why the velocity inside sub-domain is fluctuated with a large value? I think it might be about the finer grid, however I do not know how to mitigate this problem. Thank you very much for your kind consideration.

 March 28, 2005, 13:06 Re: flow in pipe with momentum and energy source #2 Phil Guest   Posts: n/a Try setting the CCL parameter 'Redistribute in Rhie Chow=t' under the GENERAL MOMENTUM SOURCE object. (You'll have to do this by changing the CCL rather; it is not currently in the GUI.) This changes some numerics details of momentum sources and often gives better results when the momentum source balances a pressure rise.

 March 29, 2005, 06:16 Re: flow in pipe with momentum and energy source #3 Atit Koonsrisuk Guest   Posts: n/a Dear Phil, Thank you very much for your kind suggestion. However I am not familiar with 'CCL', could you please say it in more details? Atit

 March 29, 2005, 16:58 Re: flow in pipe with momentum and energy source #4 Phil Guest   Posts: n/a In Pre, right-click on your subdomain option and choose 'Edit in Command Editor'. Then type in the line 'Redistribute in Rhie Chow = t' inside the GENERAL MOMENTUM SOURCE object and hit 'Process'. Pre will give a red error message saying that this is an unrecognized option (because it is an expert option); just ignore the error and run in the solver.

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Atit Koonsrisuk CFX 2 December 19, 2005 03:33 Andrew Clark FLUENT 1 October 24, 2005 14:39 Greg Perkins FLUENT 8 October 20, 2000 12:40 Greg Perkins FLUENT 0 October 13, 2000 23:03 Greg Perkins FLUENT 0 October 11, 2000 03:43

All times are GMT -4. The time now is 14:23.