CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Question regarding " Check isolated regions=f"

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   May 27, 2005, 15:55
Default Question regarding " Check isolated regions=f"
  #1
UW
Guest
 
Posts: n/a
Hi, all, When I use MFR to model a rotating turbine, I was asked to set expert parameters " check isolated regions=f" otherwise I can not run it. Do we have to do so? Anyone has the similar experience? What might cause this?

THX in advance!
  Reply With Quote

Old   May 27, 2005, 16:44
Default Re: Question regarding " Check isolated regions=f"
  #2
hannah
Guest
 
Posts: n/a
I met this kind info. before when my model had seperated solids. Mainly because when you connect your two models together using interface some dimension cannot match very well. You can check your geometry in the build to make sure the dimension is correct.

good luck

  Reply With Quote

Old   May 29, 2005, 18:40
Default Re: Question regarding " Check isolated regions=f"
  #3
Glenn Horrocks
Guest
 
Posts: n/a
Hi,

Can you describe your model? Also, does the model run when you don't have the expert parameter set? Also also, what version of CFX are you using?

Regards, Glenn Horrocks
  Reply With Quote

Old   May 30, 2005, 10:21
Default Re: Question regarding " Check isolated regions=f"
  #4
Robin
Guest
 
Posts: n/a
You will get this error message if the sover detects that two or more fluid domains are not connected. As the error message indicates, you should only set this expert parameter if you intended to set it up this way.

Most likely reason is that you forgot to add an interface or made a mistake in doing so. Check your interfaces first. The solver also writes out a <casename>.res.err file with a variable field to display the separate regions. Have a look at this in Post to see where they are not connected properly.

Regards, Robin
  Reply With Quote

Old   May 30, 2005, 10:53
Default Re: Question regarding " Check isolated regions=f"
  #5
UW
Guest
 
Posts: n/a
Hi,Glenn Horrocks the model is a stirred tank with a Rushton turbine. MFR is used. The model did run but no calculation in tank domain when the expert parameter is not set. I am using CFX 5.6

Thanks
  Reply With Quote

Old   June 5, 2005, 19:32
Default Re: Question regarding " Check isolated regions=f"
  #6
Neale
Guest
 
Posts: n/a
I'll add that this error message can happen even if you have a single fluid domain with no domain interfaces.

It is printed, in serial run mode, when the flow solver detects that a three-dimensional region of the fluid domain mesh is completely disconnected from the rest of the fluid domain.

This is bad because there may be no information to set the pressure level in that region and will cause the flow solver to blow up.
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
question about uds tanven FLUENT 2 July 5, 2015 11:22
Unanswered question niklas OpenFOAM 2 July 31, 2013 16:03
connectivity check Ted Crilly CD-adapco 2 January 20, 2005 10:13
CHANNEL FLOW: a question and a request Carlos Main CFD Forum 4 August 23, 2002 05:55
question K.L.Huang CD-adapco 1 March 29, 2000 04:57


All times are GMT -4. The time now is 17:32.