CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Directional loss model

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   December 15, 2005, 11:22
Default Directional loss model
  #1
Cenci
Guest
 
Posts: n/a
I need to simulate a thin filter where the fluid can pass only in the direction normal to the inlet surface. I would to use the directional loss model in ANSYS CFX 10. However this model considers the friction losses along the inlet normal direction but it doesn't forces the fluid to pass only in that direction.How can I do to resolve my problem?
  Reply With Quote

Old   December 15, 2005, 11:23
Default Re: Directional loss model
  #2
tommy
Guest
 
Posts: n/a
...TELL TO "REMIGIO" TRONC CONICS FANNING
  Reply With Quote

Old   December 16, 2005, 07:09
Default Re: Directional loss model
  #3
Rui
Guest
 
Posts: n/a
Hi,

If the fluid cannot pass in the other directions, the friction losses on those directions are infinite.
  Reply With Quote

Old   December 16, 2005, 17:21
Default Re: Directional loss model
  #4
Jeff
Guest
 
Posts: n/a
Set the loss coefficient in the flow direction.

Set a "factor" in the other two directions to 100. This means that the loss coefficient in the transvers directions will be 100 x K. It's not infinite, but it does the trick.

Jeff
  Reply With Quote

Old   December 18, 2005, 05:40
Default Re: Directional loss model
  #5
Cenci
Guest
 
Posts: n/a
Thank you for the advise. I've allready tought to this solution but I did'nt know the multiplier factor. It can be that 100 is a bit small, but I will try because with very high factors (10e+10) I can't obtain a solution. I use permeability in the directional losses, thus the permeability in the transvers directions is divided by the multiplier factor. Can I use again a factor of 100?
  Reply With Quote

Old   December 19, 2005, 13:26
Default Re: Directional loss model
  #6
Robin
Guest
 
Posts: n/a
Hi Cenci,

The Cartesian or Cylindrical compenents of the loss model are only used to specify direction of the flow, not losses. If you specify the "Streamwise Loss" as "No Loss" and a "Transverse Loss" with a "Streamwise Coeff. Multiplier" of 100, you should get the desired effect. Even a value of 10 should do.

A streamwise coefficient multiplier of 10 adds a resistance of 10x the local dynamic head, which should be plenty enough to keep the flow straight. If you set it too high, such as 1e10, you may cause other problems due to round-off.

Regards, Robin
  Reply With Quote

Old   December 20, 2005, 14:33
Default Re: Directional loss model
  #7
Phil
Guest
 
Posts: n/a
Small correction:

Setting the 'streamwise loss' to 'no loss' and a 'transverse multiplier' of 100 means that the transverse loss will be 0*100, which is still 0.

Instead, you need to set either: - a streamwise loss of 'no loss' (if the streamwise loss is indeed zero) and some transverse loss model using appropriately large coefficients (or small permeability) - a streamwise loss model (if the streamwise loss is nonzero) and a larger transverse loss model (eg, a multiplier of 100)
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
help for different between les model (subgrid-scale model) liuyuxuan FLUENT 1 October 2, 2009 15:25
Grid resolution for full-scale and down scaled model gravis Main CFD Forum 0 October 2, 2009 10:27
LES and combustion model Margherita Cadorin CFX 0 October 29, 2008 06:24
Directional loss model Claudia CFX 3 February 8, 2007 20:15
Kato-Launder model sam Main CFD Forum 13 September 21, 2006 10:15


All times are GMT -4. The time now is 05:21.