|
[Sponsors] |
December 15, 2005, 11:22 |
Directional loss model
|
#1 |
Guest
Posts: n/a
|
I need to simulate a thin filter where the fluid can pass only in the direction normal to the inlet surface. I would to use the directional loss model in ANSYS CFX 10. However this model considers the friction losses along the inlet normal direction but it doesn't forces the fluid to pass only in that direction.How can I do to resolve my problem?
|
|
December 15, 2005, 11:23 |
Re: Directional loss model
|
#2 |
Guest
Posts: n/a
|
...TELL TO "REMIGIO" TRONC CONICS FANNING
|
|
December 16, 2005, 07:09 |
Re: Directional loss model
|
#3 |
Guest
Posts: n/a
|
Hi,
If the fluid cannot pass in the other directions, the friction losses on those directions are infinite. |
|
December 16, 2005, 17:21 |
Re: Directional loss model
|
#4 |
Guest
Posts: n/a
|
Set the loss coefficient in the flow direction.
Set a "factor" in the other two directions to 100. This means that the loss coefficient in the transvers directions will be 100 x K. It's not infinite, but it does the trick. Jeff |
|
December 18, 2005, 05:40 |
Re: Directional loss model
|
#5 |
Guest
Posts: n/a
|
Thank you for the advise. I've allready tought to this solution but I did'nt know the multiplier factor. It can be that 100 is a bit small, but I will try because with very high factors (10e+10) I can't obtain a solution. I use permeability in the directional losses, thus the permeability in the transvers directions is divided by the multiplier factor. Can I use again a factor of 100?
|
|
December 19, 2005, 13:26 |
Re: Directional loss model
|
#6 |
Guest
Posts: n/a
|
Hi Cenci,
The Cartesian or Cylindrical compenents of the loss model are only used to specify direction of the flow, not losses. If you specify the "Streamwise Loss" as "No Loss" and a "Transverse Loss" with a "Streamwise Coeff. Multiplier" of 100, you should get the desired effect. Even a value of 10 should do. A streamwise coefficient multiplier of 10 adds a resistance of 10x the local dynamic head, which should be plenty enough to keep the flow straight. If you set it too high, such as 1e10, you may cause other problems due to round-off. Regards, Robin |
|
December 20, 2005, 14:33 |
Re: Directional loss model
|
#7 |
Guest
Posts: n/a
|
Small correction:
Setting the 'streamwise loss' to 'no loss' and a 'transverse multiplier' of 100 means that the transverse loss will be 0*100, which is still 0. Instead, you need to set either: - a streamwise loss of 'no loss' (if the streamwise loss is indeed zero) and some transverse loss model using appropriately large coefficients (or small permeability) - a streamwise loss model (if the streamwise loss is nonzero) and a larger transverse loss model (eg, a multiplier of 100) |
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
help for different between les model (subgrid-scale model) | liuyuxuan | FLUENT | 1 | October 2, 2009 15:25 |
Grid resolution for full-scale and down scaled model | gravis | Main CFD Forum | 0 | October 2, 2009 10:27 |
LES and combustion model | Margherita Cadorin | CFX | 0 | October 29, 2008 05:24 |
Directional loss model | Claudia | CFX | 3 | February 8, 2007 20:15 |
Kato-Launder model | sam | Main CFD Forum | 13 | September 21, 2006 10:15 |