CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Tangential Inlets

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes

Reply
 
LinkBack Thread Tools Display Modes
Old   March 3, 2006, 13:45
Default Tangential Inlets
  #1
Curious
Guest
 
Posts: n/a
Does anyone out there have experience modelling hydrocyclones or other devices with tangential inlets?

I know that the turbulent anisotropy inherent with the high streamline curvature in these devices necessitates the use of second order closure models (i.e. RSM SSG), but even when I use such a model, the pressure drop predicted by the code (CFX10) seems to severly underpredict the experimentally obtained pressure drop (by a factor of 2). I am running the high resolution scheme as a steady state simulation on a tetra mesh. I am only running single phase and neglecting the air core, does anyone know what type of effect this will have on the pressure drop? I have tried running two phase (water and air core) but get very poor convergence.

Anyway, it would be great to hear of other peoples experience.

Thanks
  Reply With Quote

Old   March 5, 2006, 17:17
Default Re: Tangential Inlets
  #2
Eike
Guest
 
Posts: n/a
I'm working on a hydrocyclone, too. You could try to set a max. time step, because I had to reduce it to obtain an air core. And I have to carry out transient simulations to get a good convergence. If you neglecting the air core the pressure drop will be under predicted, because water has a larger area to exhaust from the cyclone. hence, lower velocity, hence lower pressure drop.

  Reply With Quote

Old   April 5, 2011, 20:50
Exclamation
  #3
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
hi
i am unable to predict the air core that is in my simulation air core is not forming in the hydrocyclone plz tell me how can i get the air core.
thank you
asifmohammad7 is offline   Reply With Quote

Old   April 6, 2011, 07:42
Default
  #4
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
What turbulence model are you using?
ghorrocks is online now   Reply With Quote

Old   April 6, 2011, 13:10
Default
  #5
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
i am using turbilence model coz i also have to consider the effects of turbulence as the tangential inlet flow is at very high velocity 3m/sec or 4.5m/sec which causes turbulence.
asifmohammad7 is offline   Reply With Quote

Old   April 6, 2011, 18:39
Default
  #6
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Sure, but what turbulence model are you using?
ghorrocks is online now   Reply With Quote

Old   April 6, 2011, 20:03
Exclamation
  #7
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
I have tried standard k-epsilon and rsm models but air core is not forming once i have also tried les model but the same thing happened. My overflow and underflow boundary conditions are pressure outlets and i m using steady state pressure based solver.
asifmohammad7 is offline   Reply With Quote

Old   April 6, 2011, 20:17
Default
  #8
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
and sorry for my earlier silly reply ,at that time i was having headache and thought that u were asking that "why r u using turbulence model".....................
asifmohammad7 is offline   Reply With Quote

Old   April 7, 2011, 07:32
Default
  #9
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
No problem.

You are unlikely to get anything realistic with a k-e model. The curvature effects are not captured and you end up with something like solid body rotation.

RSM might work, but probably not. From what I know of this topic (it is not my area of expertise) you will need an LES approach to really get it to work.

I trust you are not trying to do a steady state LES model.
ghorrocks is online now   Reply With Quote

Old   April 7, 2011, 08:55
Default
  #10
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
Thank you for your valuable advice, now i will try to use LES WITH AN UNSTEADY APPROACH
asifmohammad7 is offline   Reply With Quote

Old   April 7, 2011, 18:12
Default
  #11
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
I see. The name of LES done in steady state is called a "mistake". I suggest you do some reading on LES approaches before you commence so you know why LES is meaningless in steady state. If you do not understand the approach you will get nowhere.
ghorrocks is online now   Reply With Quote

Old   April 10, 2011, 22:45
Default
  #12
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
hello
i am not getting any aircore using LES in unsteady state solver but i am getting an aircore with air fraction 20% using RSM.
asifmohammad7 is offline   Reply With Quote

Old   April 11, 2011, 06:29
Default
  #13
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
I repeat what I said before about LES. Have you checked that you are using a discretisation scheme with suitable levels of dissipation? Are you sure your mesh size is the correct size relative to the turbulent flow structures you aim to capture? Likewise your timestep?

If you have not done these things you have not done an LES simulation.

You might be interested in some 2-eqn, RSM and LES modelling I did years ago on vorticies in a model IC engine. It showed features like an aircore for RSM and LES approaches, and k-e gave solid body rotation. Have a look at http://hdl.handle.net/2100/248
ghorrocks is online now   Reply With Quote

Old   April 11, 2011, 23:00
Default
  #14
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
ok,thanks for sending me the link............
asifmohammad7 is offline   Reply With Quote

Old   April 11, 2011, 23:10
Default
  #15
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
No problem. Chapter 6 is the section I am referring to, it shows the effect of various turbulence models onto vortex features similar to what you are doing.
ghorrocks is online now   Reply With Quote

Old   April 13, 2011, 09:35
Default
  #16
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
thanks again............
asifmohammad7 is offline   Reply With Quote

Old   April 14, 2011, 22:41
Default
  #17
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
HI GLENN,
CAN u plz tell me how a gas-liquid interface can be created using VOF.
asifmohammad7 is offline   Reply With Quote

Old   April 15, 2011, 06:53
Default
  #18
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,923
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
1. Do the tutorials. That will show you.
2. Please do not post irrelevant comments on somebody else's thread. Start a new thread.
ghorrocks is online now   Reply With Quote

Old   April 15, 2011, 23:24
Default
  #19
New Member
 
Mohammad Asif
Join Date: Apr 2011
Posts: 15
Rep Power: 6
asifmohammad7 is on a distinguished road
thanks,i will start new thread.
asifmohammad7 is offline   Reply With Quote

Old   February 23, 2012, 07:57
Default
  #20
Member
 
arjun
Join Date: Oct 2011
Location: Tokyo, JAPAN
Posts: 66
Rep Power: 5
arjun3020 is on a distinguished road
Hi all,

Could you please tell me how to find pressure drop in cyclone using CFD post or fluent?

i have pressure contour which gives highest pressure of 1005 Pa. and lowest pressure of -303 Pa.

How to find actual pressure drop in cyclone?

See the attachment of contour.
Attached Images
File Type: jpg pressure.jpg (21.7 KB, 14 views)
arjun3020 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Tangential Component of Gradient??? Kelvin_mk OpenFOAM 0 June 29, 2011 15:30
Cylindrical coordinate system - tangential velocity alessio.nz OpenFOAM 2 December 7, 2010 06:07
Cyclone Tangential Velocity ... Abdul FLUENT 2 August 13, 2008 00:07
Multiple Inlets Charlie V FLUENT 0 May 28, 2001 02:29
create Volume with inlets Roman Bohnes FLUENT 10 December 6, 1999 05:43


All times are GMT -4. The time now is 19:10.