courant number for cfx transient run

 Register Blogs Members List Search Today's Posts Mark Forums Read

 April 4, 2006, 10:04 courant number for cfx transient run #1 Mike Guest   Posts: n/a Hi Guys, What I understood from early discussions, (I am new in this area and I am reading early discussions to understand better), Courant number is not important if I am using CFX transient run as long as I have a convergence within reasonable number of coefficient loops (like 10 coef.loop). Is that correct? I am asking this because, in my case I have courant number 999 and have convergence too. Should I worry about the courant number or not? I really need help on this and previous questions that I posted yesterday. Thanks alot, Mike

 April 4, 2006, 13:05 Re: courant number for cfx transient run #2 Robin Guest   Posts: n/a Hi Mike, That is correct. If you are converging within 3 to 6 coefficient loops, there is no need to worry about Courant number. Regards, Robin

 April 4, 2006, 13:16 Re: courant number for cfx transient run #3 James Date Guest   Posts: n/a Mike If you are converging within a small number of coefficient loops and still have a high courant number, that suggests to me your solution is quite steady. May be restarting using the steady state solver option might give you even quicker convergence. James

 April 4, 2006, 13:32 Re: courant number for cfx transient run #4 Mike Guest   Posts: n/a Robin and James, Thank you so much for your help. Actually, James, I started with steady run and after trying everything and not getting convergence to the desired values, I conclude that the flow is unsteady by its nature. That is why now I am running as transient. In my case, the Re varies alot in the domain, flow starts in a rod shape nozzle with high velocity (highest 2 m/s)(water) and it exits (expands) to a domain which the area is more than 20 times larger than tube diameter. The whole domain is order of 3 meters. Thus, even the determination of time scale is very hard. It is basically the mold flow simulation during casting steel. I am basically using SST model, CFX with 0.01 time scale for steady run and than with this initial conditions trying to run transient with 0.05 time scale. thats why I am getting very high courant number. But I was not sure whether it is critical or not. Thank you very much again. And any additional comments, helps and ideas would be very much appreciated. Thanks again, Mike

 April 5, 2006, 02:16 Re: courant number for cfx transient run #5 TB Guest   Posts: n/a Robin, For this comment "converging within 3 to 6 coefficient loops", what target residual are you referring to? 1e-4 MAX?

 April 5, 2006, 07:04 Re: courant number for cfx transient run #6 aloha5i Guest   Posts: n/a In my opinion, it depends the purpose of your simulation. If you just want to get the time averaged solution, you could ignore the importance of Courant number when you have a converged solution. HOWEVER, if you want to capture the transient of unsteady effect, you'd better have a fair small courant number. By the way, I wasn't sure what I understand about courant number. If I am wrong, pls correct me!

 April 5, 2006, 10:01 Re: courant number for cfx transient run #7 James Date Guest   Posts: n/a You're spot on Aloh5i, if you want a time accurate solution you should really have a courant number of less than one, unless the problem is approaching a steady solution

 April 5, 2006, 10:02 Re: courant number for cfx transient run #8 James Date Guest   Posts: n/a You're spot on Aloh5i, if you want a time accurate solution you should really have a courant number of less than one, unless the problem is approaching a steady solution.

 April 6, 2006, 23:48 Re: courant number for cfx transient run #9 TB Guest   Posts: n/a hmmm....There're two different opinions here.... 1. Courant number MUST always be less than one for time accurate solution. The question is: Is it always practical? Life is too short for me. 2. Courant number could be more than one for solver using implicit approach. The question is: Is solution always accurate? What I will do is: Rerun a transient simulation by doubling & halving the time steps. If solution doesn't change too much, then you can reasonably assume that it's time accurate. Any one has better & quicker approach to check the time accuracy of a transient solution?

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post wschosta OpenFOAM Running, Solving & CFD 4 July 15, 2011 15:57 maka OpenFOAM Pre-Processing 6 August 12, 2010 09:01 andre OpenFOAM 5 June 23, 2008 10:37 msrinath80 OpenFOAM Running, Solving & CFD 9 July 22, 2007 02:58 liugx212 OpenFOAM Running, Solving & CFD 3 January 4, 2006 19:07

All times are GMT -4. The time now is 07:36.