How to define roughness height in a fluid domain
 

Hi friends, I m a new user to CFX, I am solving laminar flow problem for a channel. How can I assign roughness height to any of the walls of the channel which is a fluid domain, if it is possible. If not this way can you please suggest any other way to do laminar flow in a rough channel using CFX.

your responses will be highly appreciated and acknowledged.

Thanks

Re: How to define roughness height in a fluid doma
 

Simply select "rough wall" instead of "smooth wall" for Wall Roughness on your wall boundary under the Boundary Details panel. Then enter the roughness height.

Re: How to define roughness height in a fluid doma
 

Contact Ansys-CFX and ask for the following paper.

Treatment of rough walls in CFX-10 by R. Lechner and F.R. Menter July 2005

Discusses the theory behind the rough wall calculation and most importantly you need to know the equivalent sand-grain roughness. The paper provides a reference.

Re: How to define roughness height in a fluid doma
 

Mr. Johnny, Thanks for your quick response,

Actually this option is not visible to me when I define my domain as "Fluid". only two options are in the boundary detail; free-slip and no-slip. I saw rough wall and smooth wall option under the solid face of solid-fluid interface, there is an option for roughness height. But as I have only fluid domain (laminar flow in a channel) I am not seeing the way to assign roughness height to any of the walls on the channel.

Your responses will be appreciated

Re: How to define roughness height in a fluid doma
 

You need to change the wall boundary to "no slip" before the wall roughness option appears. And you must have a turbulence model defined (ie. the case cannot be laminar if you want to specify a roughness).

And in addition to Michael's point, you can check Schlichting's book for equivalent sand grain roughnesses as well.

Re: How to define roughness height in a fluid doma
 

Thanks again,

I think problem will be solved using turbulence model with roughness defined in terms of equivalent sand grain roughness.

Re: How to define roughness height in a fluid doma
 

Thanks for your useful suggestion,

I got the point to incorporate roughness height in terms of equivalent sand grain roughness under simulation with turbulence model.

Re: How to define roughness height in a fluid doma
 

When using a omega based turbulence model, the roughness option is not visible in pre (at least not in cfx10). You have to manually add it in ccl. Using the SST model (which is omega based at the wall) will hence also not show the roughness option.

If you switch to a k-epsilon model, this option should come up in the wall boundary treatment when switching from smooth to rough wall

Bart