CFD Online Discussion Forums

CFD Online Discussion Forums (http://www.cfd-online.com/Forums/)
-   CFX (http://www.cfd-online.com/Forums/cfx/)
-   -   Modelling condensing flow (http://www.cfd-online.com/Forums/cfx/23356-modelling-condensing-flow.html)

Ryan Sidin November 30, 2006 08:20

Modelling condensing flow
 
I was wondering if CFX allows you to solve a user-defined advection-reaction type of equation for the liquid dispersion in condensing/evaporating flows. Does anyone know about this?


opaque November 30, 2006 10:55

Re: Modelling condensing flow
 
Dear Ryan,

Would you mind elaborating on the equation?

For example, you can create an ADDITIONAL VARIABLE (also known as a passive scalar). Then, you can select the type of physics transport you require: transient, advection and diffusion. They are listed as:

1 - Transport Equation = Transient + Advection + Diffusion + Sources

2 - Diffusive Transport = Transient + Diffusion + Sources

3 - Poission Equation = Diffusion + Sources.

Will this help?

Opaque

Ryan Sidin November 30, 2006 12:38

Re: Modelling condensing flow
 
Dear Opaque,

The variables I am trying to solve by means of the added equations are regrettably not passive scalars. Amongst others, they include the liquid mass fraction which links the liquid dispersion to the liquid/vapor mixture via the equation of state. Therefore you need to solve the extra transport equations (transient + advection + sources) for the extra variables simultaneously with the fluid dynamics equations for the mixture. In condensing flow theory, these extra equations are the so-called moment equations for the droplet size distribution. Viscous effects are neglected so that the fluid dynamics equations for the mixture reduce to the Euler equations for compressible flow.

So given the above: do you perhaps know if it is possible to plug such a model into CFX?

Best regards,

Ryan.

opaque November 30, 2006 12:51

Re: Modelling condensing flow
 
Dear Ryan,

In the upcoming ANSYS CFX 11.0, there is the Droplet condensation model. The documentations states that:

"The system of equations involves one continuous phase and any number of dispersed (condensed) phases. The condensed phases travel at the speed of the continuous phase.Any combination of condensed phases can exist in the solution so that for the continuous phase, mass conservation becomes:

..... Equation 251.

where the mass sources are summed over the condensed phases. The condensed phases can change size by condensation or evaporation. For a condensed phase, mass conservation is:

..... Equation 252.

where each dispersed phase has a corresponding number equation of the form:

..... Equation 253.

and is the nucleation model with units defined as the number of droplets generated per unit time per unit volume of vapor and is the nucleated droplet mass based on the critical radius . Note that the droplets are transported with the mixture velocity since no slip is assumed between the phases. The usual constraint applies for the volume fractions where:

... "

Is that what you are looking for? 11.0 does not have a DQMOM model?

Opaque


Ryan November 30, 2006 17:24

Re: Modelling condensing flow
 
Dear Opaque,

that indeed looks quite promising. If CFX 11.0 uses a moment method (either with QMOM, DQMOM, or some other type of closure) then this would be very useful to me. I am currently working as a PhD-student on a novel method to determine the droplet size distribution using the flow field solution obtained with a moment method. I have written my own fortran-code to solve the fluid dynamics equations simultaneously with either the population balance equation or the moment equations. This of course for a 1-dimensional flow in a Laval nozzle. CFX would provide a step up to 3D, more relevant test cases.

Could you perhaps show me the equations for the condensation model that will be implemented? I would very much like to see them. Do you also know if you can iplug in your own closure model?

Also, thanks for your swift and clear replies which I have been receiving thus far.

Best regards,

Ryan.


opaque November 30, 2006 17:53

Re: Modelling condensing flow
 
Dear Ryan,

Please contact your ANSYS CFX support representative, and request a copy of the solver theory documentation for the up coming 11.0 release. In particular the multiphase flow section about the Droplet Condensation Model.

You are most welcome,

Regards, Opaque


HekLer December 8, 2006 17:48

Re: Modelling condensing flow
 
It is possible to implement DQMOM in CFX using user fortran to calculate nucleation sources and the AV equations to track the moments.

There was a presentation given at the oil & gas conference in Brazil recently by someone from ESSS.


Ryan December 12, 2006 06:43

Re: Modelling condensing flow
 
This is quite an interesting remark. I can obtain the size distribution function by postprocessing the solution obtained with the moment method. What is not clear to me is that whether or not the MOM-method you plug in can be solved simultaneously with the fluid dynamics equations, and not in a post-processing stage. By the way, in the solver theory of CFX-11 (preview version), it is mentioned that the condensation model simply uses an equivalent monodisperse distribution (i.e. a mean radius) to determine the growth contribution in the method of moments.

HekLeR December 14, 2006 01:02

Re: Modelling condensing flow
 
The DQMOM moment equations can be solved simultaneously with the other equations and used as input into the particle diameter calculation (eg: mean diameter calc).

You are right. The droplet model in CFX 11 is monodisperse. Polydisperse DQMOM is coming for CFX 12.



All times are GMT -4. The time now is 00:47.