CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

CFX to model convection cells

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   December 6, 2006, 14:48
Default CFX to model convection cells
  #1
FER
Guest
 
Posts: n/a
Hello, I am a new user to CFX and I want to model Benard convection cells with CFX. I went over the free surface tutorial and its a good starting point but is there a another tutorial for free surface modeling with CFX? My model is a liquid in a container with the side walls insulated, heat addition from below and at the top the water is in contact with air. How do I go about setting up boundry conditions for such a model? I created a rectangle with six regions - bottom, two sides (insulation), two sides (symmetry) (trying to model this in 2-D), and top; I applied the symmetry and bottom constant temp boundry. Not sure how to incoporate the side insulation and VF conditions. -FER
  Reply With Quote

Old   December 6, 2006, 17:39
Default Re: CFX to model convection cells
  #2
Glenn Horrocks
Guest
 
Posts: n/a
Hi,

If the free surface is not important or does not move much then the simulation will be far simpler if you just put a wall with appropriate thermal boundary conditions.

Glenn Horrocks
  Reply With Quote

Old   December 6, 2006, 20:13
Default Re: CFX to model convection cells
  #3
FER
Guest
 
Posts: n/a
Glenn, thanks for the info. But the surface interaction is what I want to monitor.
  Reply With Quote

Old   December 7, 2006, 17:26
Default Re: CFX to model convection cells
  #4
Glenn Horrocks
Guest
 
Posts: n/a
Hi,

Can't the side walls just be adiabatic walls? That's pretty straight forward.

What part of the multiphase setup is confusing you?

Glenn Horrocks
  Reply With Quote

Old   December 13, 2006, 01:57
Default Re: CFX to model convection cells
  #5
Bak_Flow
Guest
 
Posts: n/a
Hi FER,

i would take Glenn's suggestion first since adding free surface to the calculation would appear to be a secondary effect once you get the weak convection started.

The problem you are trying to to is infact very hard to simulate unless you are very careful in controling factors which affect the stability and symmetries of the problem. You want to eliminate any damping, numerical (ie non physical perturbations) and breaking of symmetry inherrent in the code.

For example I would use a very symmetrical structured grid for the problem as an unstructured grid even with all other bc and geometric symmetries will not necessarily lead to a symmetrcal solution.

Even if you have a symmetric problem domain, symmetric boundary conditions, and symmetry in the body forces (the last 2 ammount to symmetries in the RHS of A{x} = b) the code can introduce assymetries which are not physical.

You will also want numerical discretizations which do not introduce unnecessary damping nor assymetries. Crank Nicholson in time and CDS in space are good choices. I know there is an expert flag in CFX to switch to CDS. Never use hi-res or something like that for this kind of problem. Hence my comment about not trying to do the VOF at first because it uses a compressive discretization like hi-res.

There are some good books on Non-linear dynamics and the general issues to simulate such problems. Try Seydel(sp): From Equilibrium to Chaos it has lots of references.

I hope this is of help.

Regards,

Bak_Flow
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Need Help to Enable Wall Boiling Model in CFX cjhaw CFX 3 September 26, 2013 09:40
Basic advice on Importing Solid Edge model to CFX needed. stephen__white CFX 1 February 9, 2011 19:40
Turbulence model for CFX moving mesh songxguan CFX 7 June 28, 2009 21:05
Import Fan 3D Model - Workbench or CFX? Stewart Long CFX 2 October 28, 2008 05:05
Use of 1 equation turbulence model in CFX 4.3 Niels Deen CFX 0 July 19, 2000 08:50


All times are GMT -4. The time now is 23:45.