|
[Sponsors] |
January 25, 2007, 05:44 |
2D Simulations
|
#1 |
Guest
Posts: n/a
|
Hallo everybody!
Does anyone know how to create a 2D (quasi) simulation in CFX10? The help file says it's possible, but following those steps I always get a message: "CFX can only operate on Solid Volumes!". I want to create a simple planar rectangular surface with one moving boundary, no inlets and outlets and simulate gas behaviour bounded by the geometry. Thanks a lot for any replies! Greetings, Uros. |
|
January 25, 2007, 06:47 |
Re: 2D Simulations
|
#2 |
Guest
Posts: n/a
|
Use the forum search function.
|
|
January 25, 2007, 16:27 |
Re: 2D Simulations
|
#3 |
Guest
Posts: n/a
|
You have to extrude, 1 cell deep, in your mesh software.
|
|
January 26, 2007, 07:07 |
Re: 2D Simulations
|
#4 |
Guest
Posts: n/a
|
You need to create a volume, to simulate 2D simulation, so u have to choose one unite in the Z direction, and ur reall values in the (x,y) direction. Tarek
|
|
January 27, 2007, 04:30 |
Re: 2D Simulations
|
#5 |
Guest
Posts: n/a
|
Basically, you have to know that CFX is a 3-D solver and not a 2-D, therefore, you need to have a 3-D mesh for CFX. For simulating 2-D, extrude the mesh (one cell thick) in the Z direction. Or if you are trying to do a 2-D axisymmetry, then extrude by rotation by say 1 degree or max 5-degree, depending on the complexity of the model. Since you would be having a slip-wall boundary condition on those extruded symmetry faces, the fluxes calculated are equated to 0. This acts as symmetry BC.
|
|
January 29, 2007, 13:36 |
Re: 2D Simulations
|
#6 |
Guest
Posts: n/a
|
Don't use a free slip wall, use Symmetry or, if there is swirl, create a Periodic interface.
-Robin |
|
January 29, 2007, 20:22 |
Re: 2D Simulations
|
#7 |
Guest
Posts: n/a
|
Why not Robin....?
Regards, Bak_Flow |
|
February 24, 2007, 08:04 |
Re: 2D Simulations
|
#8 |
Guest
Posts: n/a
|
Hi Bak_Flow,
There is a subtle difference in the discretization at the wall. A free slip wall will not enforce a zero gradient, whereas a symmetry plane will. How the solver does this also affects the calculation of gradients which are used for second order terms. To make a long story short, if you have a grid one element thick and use a free slip wall the advection term will only be first order upwind. So use symmetry. Regards, Robin |
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Periodic boundary conditions in 3D Eulerian granular flow simulations | dsm | FLUENT | 4 | March 2, 2012 19:04 |
Hardware selection for steady/unsteady incompressible, turbulent and cht simulations | maddalena | OpenFOAM | 2 | July 13, 2011 08:55 |
Cumulative continuity error large in parallel simulations | xiao | OpenFOAM | 3 | March 7, 2011 04:13 |
Timestepping in two - phase Simulations using RSM | challenger85 | CFX | 0 | January 4, 2010 05:00 |
URANS and Transient Simulations | bob | Main CFD Forum | 0 | October 1, 2003 03:54 |