CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

about 2D mesh

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   February 14, 2007, 22:59
Default about 2D mesh
  #1
Eric
Guest
 
Posts: n/a
Dear Friends,

I made the 2D Hexa Mesh in ICEM (Extrude 1 layer).

After exporting *.msh to CFX-pre, I cannot find the Outlet, Inlet,etc. which I pre-defined in ICEM.

Could you give me some advice.

Thank you in advance.

Eric
  Reply With Quote

Old   February 15, 2007, 10:47
Default Re: about 2D mesh
  #2
Shastri
Guest
 
Posts: n/a
I think you can not read the *.msh file directly into CFX Pre. I guess that would be a Fluent input file. For CFX, you have to go to 'Output'->'Select Solver' in ICEM, choose 'CFX5' or later. It writes a file without an extension (default name is 'cfx5' or something if I remember right).

You can now open CFX Pre and in the 'Mesh Import' dialogue box, choose input format as 'ICEM CFD', give an assembly name and choose appropriate units.

Now you should be able to identify all the volumes and surfaces as they were in ICEM. Hope it helps. Shastri
  Reply With Quote

Old   February 15, 2007, 10:53
Default Re: about 2D mesh
  #3
Eric
Guest
 
Posts: n/a
Thank you,Mr. Shastri.

I will try.

I can import 3D ICEM mesh to CFX-pre. But for 2D mesh, in CFX-pre, I cannot see the different parts that I had defined in ICEM.

Mang thanks.
  Reply With Quote

Old   February 15, 2007, 11:02
Default Re: about 2D mesh
  #4
Shastri
Guest
 
Posts: n/a
Just make sure that you have named all the surfaces in ICEM and made sure all the surface mesh is projected to correcponding surfaces. On ICEM Hexa, this means you must explicitly project the faces to surfaces. If this is done correctly, you should be able to see the different shell meshes (quad or tri) by selecting the family name in ICEM. If that is done correctly and if you use the export method I mentioned earlier, you should be able to see the names. I used this method to simulate 2D airfols with 1-cell thick mesh. Shastri
  Reply With Quote

Old   February 15, 2007, 13:07
Default Re: about 2D mesh
  #5
myron
Guest
 
Posts: n/a
If you actually built the 2d-mesh in Hexa (2D blocks - not 3D) - then you probably gave the part names to the 2D curves. Make sure you project all the bounding edges of the 2D blocks to appropriate curves. This will yield LINE elements in the parts you specifed (once you convert to unstructured mesh). When you do the extrusion, you want to pick all the elements (QUADS and LINES). After you have the one-cell-thick mesh - see if you have quads defining your inlet, outlet, etc. If not - you'll need to select the appopriate elements (quads from the extruded 'sided') and place them into the correct parts.
  Reply With Quote

Old   February 16, 2007, 09:11
Default Re: about 2D mesh
  #6
Jesper
Guest
 
Posts: n/a
Firstly as Shaatri mentioned you must be sure you have associated all your edges correctly. then...There are two different ways you can extrude your mesh from 2D to 3D in ICEM, of which one of them can give you the mentioned problem. You should look under the tab "blocking" where you would finde the possibility "create block" - chose this, and you will be able to use: "2D to 3D".

This should solve your problem, unless this is the method already used.
  Reply With Quote

Old   March 1, 2007, 15:24
Default Re: about 2D mesh
  #7
DGaden
Guest
 
Posts: n/a
After extruding a 2D mesh I found all my walls and surfaces in the new dimension lost their names, and couldn't be selected in pre. I found that when I loaded an extruded geometry with the walls named, then chose "Associate mesh with geometry" under the "Repair / edit" mesh option in ICEM, the walls came back.
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] surface mesh merging problem everest ANSYS Meshing & Geometry 39 June 5, 2013 19:02
snappyHexMesh won't work - zeros everywhere! sc298 OpenFOAM Native Meshers: snappyHexMesh and Others 2 March 27, 2011 21:11
Meshing aifoil in ICEM student123a ANSYS Meshing & Geometry 13 December 8, 2010 11:40
mesh missing after export in gambit morteza08 ANSYS Meshing & Geometry 1 July 26, 2010 01:10
2d irregular grid Remy Main CFD Forum 1 December 22, 2008 05:49


All times are GMT -4. The time now is 14:04.