
[Sponsors] 
September 18, 2007, 10:38 
how find fluctuating velocity

#1 
Guest
Posts: n/a

Hi
I'am using ansys cfx 10, and I'am making a simulation of jet flow at low Re numbers. I used a SST model and now I don't know how find the fluctuating velocity of the flow. Someone can help me. Thanks 

September 18, 2007, 15:11 
Re: how find fluctuating velocity

#2 
Guest
Posts: n/a

You can calculate the magnitude of the fluctuating component from the Turbulence Kinetic Energy. If you look it up in the documenation, you'll see that the turbulent kinetic energy (k) is defined as:
k=1/2*u^2 where u is the fluctuating component of velocity. Based on this you can estimate the fluctuating component as: u = sqrt(2k) In CEL that would be: Fluctuating Component = sqrt(2*Turbulence Kinetic Energy) CycLone 

September 19, 2007, 02:20 
Re: how find fluctuating velocity

#3 
Guest
Posts: n/a

Thank you so much


September 19, 2007, 10:32 
Re: how find fluctuating velocity

#4 
Guest
Posts: n/a

For anisotropic flow , the kinetic energy is defined as k = ½ * (u'^2 + v'^2 + w'^2) = ½ * (3 * u'^2) = 3/2 u'^2 where (') denotes fluctuating velocity component. Agree?


September 19, 2007, 13:35 
Re: how find fluctuating velocity

#5 
Guest
Posts: n/a

Yes, good point. You're right, since u is a vector, the turbulent kinetic energy should be 3/2u'^2. My bad.
CycLone 

June 22, 2010, 02:16 

#6 
Member
Derwin Parkin
Join Date: Feb 2010
Posts: 34
Rep Power: 7 
Hi guys,
What do I do if I want to find u', v' and w' (the fluctuating velocity in each direction)? Using this method would only allow me to find u'. Or am I understanding this wrong? And what exactly do you mean by anisotropic flow? 

June 22, 2010, 19:54 

#7 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,572
Rep Power: 90 
If you are using an isotropic turbulence model (eg the 2eqn models) then u', v' and w' is the same by definition. Only the RSM model allows for a difference between u', v' and w'.
Look at a turbulence modelling textbook for more details, "Turbulence Modelling for CFD" by Wilcox is the one I recommend. 

April 20, 2011, 06:23 

#8 
New Member
José María Carrillo
Join Date: Apr 2011
Location: Spain
Posts: 9
Rep Power: 6 
Hi!
I'm using the BSL Reynolds Stress model and I want to know how can I find u', v' and w' (the fluctuating velocity in each direction). Can they be calculated with the "Reynolds Stress uu, vv..." variable or with another variable? How can I obtain this terms? Thanks 

April 20, 2011, 18:59 

#9 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,572
Rep Power: 90 
See a turbulence modelling textbook eg Wilcox.


April 2, 2012, 11:09 

#10 
Senior Member
Join Date: Jan 2010
Location: Germany
Posts: 268
Rep Power: 9 
But in the CFX Documentation it is written explicitly that Reynolds Stresses may be used by means of CCL!! But How?
Jessica 

April 4, 2012, 07:27 

#11 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,572
Rep Power: 90 
The CFX reference manual lists the availabel CEL variables. I think Reynolds Stresses are available if you have an appropriate turbulence model enabled.


April 4, 2012, 07:41 

#12 
Senior Member
Join Date: Jan 2010
Location: Germany
Posts: 268
Rep Power: 9 
yeah i have chosen one of them and i am awaiting the reply of ANSYSSupport


April 5, 2012, 02:36 

#13 
New Member
Erik Bjerklund
Join Date: Jul 2009
Location: Sweden
Posts: 3
Rep Power: 8 
Right click in the expression window and all available functions and expressions are shown.
e.g. massFlowAve(Reynolds Stress uu + Reynolds Stress uw)@outlet 

April 5, 2012, 03:49 

#14 
Senior Member
Join Date: Jan 2010
Location: Germany
Posts: 268
Rep Power: 9 
I need them in Pre and not only at Boundaries...


April 5, 2012, 08:35 

#15 
New Member
Erik Bjerklund
Join Date: Jul 2009
Location: Sweden
Posts: 3
Rep Power: 8 
You can use them in pre and monitoring them while running, this can also be done at specified points or max/min/ave of the entire domain
You can also use variables while specifying the boundaries. for example make the velocity or temperature dependent of time or other variable. question is if you would get the time fluctuationg part from abstractin u.trans avg from u p, li { whitespace: prewrap; } Velocity u  Averaged Velocity u of that I am not sure. 

April 5, 2012, 13:24 

#16 
Senior Member
Join Date: Jan 2010
Location: Germany
Posts: 268
Rep Power: 9 
I know that i am working with it since the begin of my phd but i know i tried to use RSM and want to calibrate the rs.vv to zero (another topic) by introducing some damping.. but it still showing me that the variables are not available..
jessica 

June 24, 2012, 06:55 

#18 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,572
Rep Power: 90 
If you are doing a RSM model it will be in the results file by default (unless you took it out ). You will find it under the puzzlingly labelled "..." button.


June 24, 2012, 09:30 

#19 
Super Moderator

I found it. Just made the contour plot and found them as variables.
One more thing. As we know that linear eddy viscosity models assumes that the turbulence stress is linked to mean rate of strain or mean velocity gradient. So in that case uu, vv and ww are equal. While in RSM model they have markable difference in magnitude. But still I have good results with these two equation models. Why? 

June 24, 2012, 19:26 

#20 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,572
Rep Power: 90 
The RSM and 2eqn models use very different approaches, as you point out. If uu, vv and WW are quite different and therefore the turbulence is anisotropic you would think that means the 2eqn models should have problems. Your report that they match suggests:
1) Turbulence is not significantly affecting the flow  for instance an airfoil simulation will predict very similar lift regardless of the turbulence model. The drag will be quite different though. 2) It could be the anisotropy is not significantly affecting the flow. 3) It could be just luck, and at a different operating point results are quite different 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Problem with assigned inlet velocity profile as a boundary condition  Ozgur_  FLUENT  5  August 25, 2015 04:58 
How to calculate Velocity?  Kali Sanjay  Phoenics  1  May 1, 2006 13:57 
Velocity Underrelaxation in SIMPLE type methods  Matt U.  Main CFD Forum  6  July 4, 2005 05:29 
where to find velocity field for square pipes???  enrico  Main CFD Forum  2  February 4, 2005 12:32 
fluid fluctuating velocity at particle position  kulwinder  FLUENT  0  June 17, 2004 00:52 