CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Lagrangian Particle Tracking model In CFX

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   April 11, 2008, 15:15
Default Lagrangian Particle Tracking model In CFX
  #1
Kushagra
Guest
 
Posts: n/a
I am facing big times problem with the Lagrangian particle tracking model in CFX. I simulated flow in a hydrocyclone and once I obtained quite good flow field, I started tracking the particles with all the applicable forces applied (Turbulent dispersion force, pressure gradient force, gravity, byouancy) BUT I get wrong results all the time.

Could some one comment his experiences with Lagrangian model and accuracy of it in CFX-11? I have heard from other people as well that they have been facing the same problem as that of mine.

Please help. Thanks very much.

Regards, Kushagra
  Reply With Quote

Old   September 19, 2009, 11:57
Default
  #2
New Member
 
Rodrigo Vallejo Pereira
Join Date: Sep 2009
Posts: 5
Rep Power: 7
rvallejo is on a distinguished road
Im facing the same problem. Could anyone help us ?

Thanks
rvallejo is offline   Reply With Quote

Old   September 19, 2009, 19:16
Default
  #3
Member
 
Join Date: Mar 2009
Posts: 48
Rep Power: 8
John is on a distinguished road
Quote:
Originally Posted by Kushagra
;87439
I am facing big times problem with the Lagrangian particle tracking model in CFX. I simulated flow in a hydrocyclone and once I obtained quite good flow field, I started tracking the particles with all the applicable forces applied (Turbulent dispersion force, pressure gradient force, gravity, byouancy) BUT I get wrong results all the time.

Could some one comment his experiences with Lagrangian model and accuracy of it in CFX-11? I have heard from other people as well that they have been facing the same problem as that of mine.

Please help. Thanks very much.

Regards, Kushagra
Can you provide details what's wrong with your results?
John is offline   Reply With Quote

Old   September 22, 2009, 12:57
Default
  #4
New Member
 
Rodrigo Vallejo Pereira
Join Date: Sep 2009
Posts: 5
Rep Power: 7
rvallejo is on a distinguished road
Lagragian model provides a result where all the particles go to the underflow. I 'm using turbulent dispersion and Schiller Naumann drag force. I've tried virtual mass force and pressure gradiente force in addition, but they didn't work as well.

I'm using ANSYS CFX 11.01.

Best Regards,
Vallejo
rvallejo is offline   Reply With Quote

Old   September 26, 2009, 18:20
Default
  #5
New Member
 
Rodrigo Vallejo Pereira
Join Date: Sep 2009
Posts: 5
Rep Power: 7
rvallejo is on a distinguished road
Quote:
Originally Posted by John View Post
Can you provide details what's wrong with your results?
Lagragian model provides a result where all the particles go to the underflow. I 'm using turbulent dispersion and Schiller Naumann drag force. I've tried virtual mass force and pressure gradiente force in addition, but they didn't work as well.

I'm using ANSYS CFX 11.01.

Best Regards,
Vallejo
rvallejo is offline   Reply With Quote

Old   March 12, 2010, 19:26
Default
  #6
New Member
 
lee
Join Date: Mar 2010
Posts: 10
Rep Power: 7
leeportnoff is on a distinguished road
When the particle diameters become small (less than 10 microns in air) the fluid can no longer be considered continuous. The drag coefficient on each particle, which is calculated using standard correlations (Schiller Neauman), must be divided by the Cunningham correction factor. The correction factor is greater than 1 which means that the effective particle drag coefficient goes down.
The cunningham correction factor is not used in CFX but if you use the "Particle Transport Drag Coefficient" in the Momentum Transfer tab in Pre you can specify any drag model that you need using CEL relations. First try to redo the Schiller Nauman relation, verify it with the CFX implementation and then correct it with the Cunningham factor. The Schiller Nauman will be the hardest part because it is an implicit relation.
leeportnoff is offline   Reply With Quote

Old   May 12, 2010, 04:50
Default
  #7
Member
 
Rain
Join Date: Apr 2009
Posts: 40
Rep Power: 8
gravis is on a distinguished road
Quote:
Originally Posted by leeportnoff View Post
When the particle diameters become small (less than 10 microns in air) the fluid can no longer be considered continuous. The drag coefficient on each particle, which is calculated using standard correlations (Schiller Neauman), must be divided by the Cunningham correction factor. The correction factor is greater than 1 which means that the effective particle drag coefficient goes down.
The cunningham correction factor is not used in CFX but if you use the "Particle Transport Drag Coefficient" in the Momentum Transfer tab in Pre you can specify any drag model that you need using CEL relations. First try to redo the Schiller Nauman relation, verify it with the CFX implementation and then correct it with the Cunningham factor. The Schiller Nauman will be the hardest part because it is an implicit relation.
Does anyone have experience carrying out this implementation in CFX?
gravis is offline   Reply With Quote

Old   May 12, 2010, 05:41
Default
  #8
New Member
 
charles
Join Date: Mar 2009
Posts: 1
Rep Power: 0
sei2006 is on a distinguished road
check your turbulence model firstly.
sei2006 is offline   Reply With Quote

Old   December 2, 2010, 22:18
Default
  #9
New Member
 
lee
Join Date: Mar 2010
Posts: 10
Rep Power: 7
leeportnoff is on a distinguished road
LEVEL OF DIFFICULTY: ADVANCED
To get this working, I had to write a custom FORTRAN routine based on the pt_mom_source.F file included in ANSYS.
I compiled a custom pt_mom_custom.dll,
Expressions, functions, and variables > user routines > insert user routine and call 'drag'
option: particle user routine
calling name: pt_mom_custom
library name: pt_mom_custom
library path: <path to winnt> containing pt_mom_custom.dll

Then insert User Function
user routine name: drag
argument units: []
results units: []

Now, in your domain, under the 'Fluid pair models'
for 'drag force' select 'none'
check 'particle user source'
you should see your 'drag' routine for particle user routine

Lastly choose arguments and return variables.
** important ** the order you select these variables must match the order in your pt_mom_custom.h routine. i.e. It is by order of appearance, that cfx knows input DIAM_PT means particle.Mean Particle Diameter.
leeportnoff is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Lagrangian particle tracking jiejie OpenFOAM 14 December 9, 2011 23:53
Blood Damage Modelling via Particle Tracking in a Centrifugal Heart Pump scatman CFX 5 May 5, 2011 07:23
Particle Tracking for ion Jun CFX 2 August 31, 2010 08:19
Reynolds Stress model in CFX vs Fluent Tim CFX 1 October 7, 2009 06:19
2D vs 3D model, Eulerian vs Particle tracking Itchie CFX 0 April 10, 2008 05:04


All times are GMT -4. The time now is 15:10.