CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

CFX 11 Scheme for LES in Multiphase

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   February 25, 2009, 03:07
Default CFX 11 Scheme for LES in Multiphase
  #1
Man
Guest
 
Posts: n/a
Hi

I am working on an academic problem involving use of LES for multiphase systems. For LES Single Phase, the Central Difference Advection scheme is available, but this is not the case for Multiphase. Can anyone from CFX support, let me know as to how i can turn on the Central Difference Advection scheme for LES Multiphase system. This was i tink possible with CFX 4 and 5. Also, what scheme would be a better alternative to CDS (higher order scheme that won't lead to diffussion), is it High Resolution or Blend Factor around 0.75 or 1. Can anyone please clarify. Thank you for your help. Regards, Mandar
  Reply With Quote

Old   February 25, 2009, 19:53
Default Re:
  #2
Man
Guest
 
Posts: n/a
Hi Glen , do you have any knowledge of this. I have gained lots of info through your various posts. Thanks.
  Reply With Quote

Old   February 25, 2009, 23:10
Default Re: CFX 11 Scheme for LES in Multiphase
  #3
lkf
Guest
 
Posts: n/a
My understanding of HRS is that the blend factor is adjusted locally to be as close to 1 as possible, whereas a specified blend factor of 'x' will be enforced throughout the entire domain.

So, from an acedemic perspective, specified blend factor = 1 would be preferable to HRS. However, the difficulties associated with getting a tightly converged solution using specified blend = 1 may be very difficult.

Perhaps there is a way to create an isovolume in POST that shows beta values above a certain value? Then you could visualise how much of your domain is/isn't near a fully CDS solution while still taking advantage of the stability of HRS.
  Reply With Quote

Old   February 26, 2009, 17:44
Default Re: CFX 11 Scheme for LES in Multiphase
  #4
Glenn Horrocks
Guest
 
Posts: n/a
Hi,

(It is nice to be loved )

High res differencing uses second order differencing where-ever it reckons it will not generate too unphysical an overshoot and for those locations blends in first order upwinding. This is discussed in the documentation. You can also see the areas where it is blending the first order differencing with the ".beta" variables.

But if you are doing LES then forget high-res differencing scheme, it is too diffusive in most cases.

The hybrid differencing scheme, even set to pure second order is still too diffusive for most LES work as it is still an upwinding scheme (although a lot less diffusion than a first order upwinding scheme).

CFX has the central differencing scheme, it is just not available in CFX-Pre. You have to put it in the CCL. If you look in the file (CFX ROOT)/etc/RULES you will find an entry "SINGLETON: ADVECTION SCHEME". This will list all the available differencing schemes and central differencing is one of them.

For most LES work you will need CDS to eliminate numerical diffusion.

You may also be interested in my PhD thesis where I did soem preliminary LES work on CFX4 where I used a second order upwinding scheme to provide my sub-grid dissipation rather than a sub-grid model. I think the study was in chapter 5 or 6. http://hdl.handle.net/2100/248

Glenn Horrocks
  Reply With Quote

Old   February 26, 2009, 20:36
Default Re: CFX 11 Scheme for LES in Multiphase
  #5
Man
Guest
 
Posts: n/a
Hello lkf and Glenn,

Thank you for sharing the information. It was very useful. I will have a look at the .beta profile for my present runs. Thanks. For my future simulations, I manually changed the advection option to 'Central Difference' in ccl and imported it to CFX-Pre 11. I get an error in Pre "This does not match any of the allowed values, and while saving the def file, it says that the definition file may not run in the solver. But, it is running and I can see the advection scheme coming printed as 'Central difference'. So, any idea, is it indeed running the Central Difference? Thanks for the help.

Reg, Mandar
  Reply With Quote

Old   March 1, 2009, 18:18
Default Re: CFX 11 Scheme for LES in Multiphase
  #6
Glenn Horrocks
Guest
 
Posts: n/a
Hi,

CFX-Pre does not support CDS so it will give an error. The solver does and should work fine. Just check the CDS scheme is actually being used and Pre has not overwritten it - check the CCL statements at the start of the output file.

Glenn Horrocks
  Reply With Quote

Old   March 30, 2009, 23:32
Default
  #7
Member
 
Mandar
Join Date: Mar 2009
Posts: 39
Rep Power: 8
mixer is on a distinguished road
Hi

Can someone plese let me know on this. Is there a bug in CFX 11 LES runs, even though i select the turbulent kinetic energy and dissipation variables in tranres and tranStat files, it doesn't get written in ouput result files. Thanks.

Reg,
Mandar
mixer is offline   Reply With Quote

Old   May 19, 2009, 00:31
Default
  #8
LSC
Member
 
LSC
Join Date: May 2009
Posts: 58
Rep Power: 8
LSC is on a distinguished road
Hi, I faced the same problem as I wanted to select the Central Differencing but from the manual this scheme is only available for LES..Is there any guide to work around with it as I want to study the effect of different discretization schemes for my airfoil simulations..
LSC is offline   Reply With Quote

Old   May 21, 2009, 00:58
Default
  #9
Member
 
Mandar
Join Date: Mar 2009
Posts: 39
Rep Power: 8
mixer is on a distinguished road
Hi LSC

There sure is. You just have to write in ccl file 'Central difference' and import it back. While saving the solver definition, you may see an error and an warning, but you just ignore it and save it. It works.
mixer is offline   Reply With Quote

Old   May 21, 2009, 01:31
Default
  #10
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,797
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Quote:
Originally Posted by mixer View Post
Hi

Can someone plese let me know on this. Is there a bug in CFX 11 LES runs, even though i select the turbulent kinetic energy and dissipation variables in tranres and tranStat files, it doesn't get written in ouput result files. Thanks.

Reg,
Mandar
Hi,

In an LES simulation the turbulence kinetic energy is calculated directly from the velocity field, it does not have a separate variable. Unless you are using a sub-grid model which includes a k component, then it should be available. I think the default SGS model is Smagorinsky (not sure) and that does not have a k component.

Glenn Horrocks
ghorrocks is offline   Reply With Quote

Old   May 21, 2009, 06:06
Default
  #11
LSC
Member
 
LSC
Join Date: May 2009
Posts: 58
Rep Power: 8
LSC is on a distinguished road
Hi Mixer, thanks a lot for the reply! Anyway is there any way I can activate incompressible flow in CFX? Also, I was rather confused about the reference pressure in CFX. From the manual it says that the reference pressure is the absolute pressure reference datum. So since I am taking perfect vacuum pressure as reference, Shall I set the reference pressure under the domain fluid model to 0[Pa] and proceed on to get my outlet BC's relative static pressure to 101325[Pa] since I am running simulations for airfoil. Is this the correct way of setting? Is there any difference between this "Reference Pressure" and the "Operating Pressure" found in Fluent? Please advice.
LSC is offline   Reply With Quote

Old   May 25, 2009, 02:45
Default
  #12
Member
 
Mandar
Join Date: Mar 2009
Posts: 39
Rep Power: 8
mixer is on a distinguished road
thanks glen. I checked with 12 version also, as u said even this does not give kinetic energy as a separate variable. If i wish to obtain an averaged turbulent kinetic energy in post, then is their any user function/user routine which will help me get mean of a field. i may need to get fluctuatiing velocities at each time step to calculate kinetic energy, and to get its mean. Similarly, for energy dissipation rate, where i will have to use stress.
thank you,
regards
Mandar

Quote:
Originally Posted by ghorrocks View Post
Hi,

In an LES simulation the turbulence kinetic energy is calculated directly from the velocity field, it does not have a separate variable. Unless you are using a sub-grid model which includes a k component, then it should be available. I think the default SGS model is Smagorinsky (not sure) and that does not have a k component.

Glenn Horrocks
mixer is offline   Reply With Quote

Old   May 25, 2009, 20:26
Default
  #13
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,797
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Hi,

Yes, the transient statistics output will be useful for you. Have a look in the output tab on CFX-Pre and select the transient statistics. You can then calculate time averaged flows, time averaged variances (which can be used the calculate k) etc.

Glenn Horrocks
ghorrocks is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
How to decide interfacial length scale in Mixture Model of CFX multiphase simulation? TommySean CFX 6 April 6, 2012 23:46
CFX pressure in Simulations problem nasdak CFX 1 April 14, 2010 13:22
CFX GUI Background Colors UnderwaterAlex CFX 2 February 12, 2008 13:09
Compressibility on multiphase flow on CFX 11 Bayard Morales CFX 0 October 5, 2007 14:59
Multiphase modelling in CFX sam CFX 2 July 12, 2003 01:17


All times are GMT -4. The time now is 14:20.