CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

CFX gravity driven free surface flow tutorial

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree2Likes

Reply
 
LinkBack Thread Tools Display Modes
Old   July 22, 2009, 11:16
Default
  #21
Senior Member
 
ckleanth's Avatar
 
George
Join Date: Mar 2009
Location: Birmingham, UK
Posts: 257
Rep Power: 9
ckleanth is on a distinguished road
is the inlet and outlet fully submerged in the pond?
__________________
Top 4 tips
1. Knowledge is everything and Ignorance is dangerous.
2. Understand your limitations and try to eliminate them.
3. Get yerself a bike and hoon the chuffer. You will soon learn why dogs like to hang their heads out the car window.
4. Please before asking any questions on how to run simulations in CFX, go though all the tutorials
ckleanth is offline   Reply With Quote

Old   July 22, 2009, 19:32
Default
  #22
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ckleanth View Post
is the inlet and outlet fully submerged in the pond?
Yes, the inlet and outlet are fully submerged and also I would like to model a position of inlet and outlet when their crown is just beneath the water surface.

Thanks for giving your time to study my problem.
Sher is offline   Reply With Quote

Old   July 22, 2009, 20:30
Default
  #23
Senior Member
 
ckleanth's Avatar
 
George
Join Date: Mar 2009
Location: Birmingham, UK
Posts: 257
Rep Power: 9
ckleanth is on a distinguished road
two remarks
- if both inlet and outlet is submerged i'm not sure why you're trying to model air? what do you want to learn from the simulation? maybe a picture/sketch of the problem would be helpful so that people can understand what you want to achieve, and would minimize guessing.

-when the inlet is somewhere between the free surface of the phase you will need to restrict the Inlet BC according to where you defined the free surface in a similar way you created the outlet BC.
__________________
Top 4 tips
1. Knowledge is everything and Ignorance is dangerous.
2. Understand your limitations and try to eliminate them.
3. Get yerself a bike and hoon the chuffer. You will soon learn why dogs like to hang their heads out the car window.
4. Please before asking any questions on how to run simulations in CFX, go though all the tutorials
ckleanth is offline   Reply With Quote

Old   July 22, 2009, 21:02
Default
  #24
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ckleanth View Post
is the inlet and outlet fully submerged in the pond?
Thanks for your advices. The sketch of the model is attched. Although in this sketch the inlet and outlet are just below the free surface.
Attached Files
File Type: doc Sketch of the model.doc (79.5 KB, 67 views)
Sher is offline   Reply With Quote

Old   July 22, 2009, 23:03
Default
  #25
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,825
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
hi,

Does the free surface do much? If it stays pretty much flat then I would not do a free surface simulation at all but a single phase model with the top surface a pressure boundary, of possibly a degassing boundary if relevant. If this simplification is valid it will make things MUCH easier.

Glenn Horrocks
ghorrocks is offline   Reply With Quote

Old   July 22, 2009, 23:11
Default Free surface
  #26
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
hi,

Does the free surface do much? If it stays pretty much flat then I would not do a free surface simulation at all but a single phase model with the top surface a pressure boundary, of possibly a degassing boundary if relevant. If this simplification is valid it will make things MUCH easier.

Glenn Horrocks
Hi thanks for your reply. Actually I have modelled as single phase model with top as a symmetry and I got very good results but as a requirement of my investigation I would like to compare these results with top as free surface. In the geometry of my model I would like to keep the inlet and outlet at 0.23 m above the bottom and free surface above this (I mean the free surface may be at 0.24m or 0.25m). Please suggest me, if possible?
regards
Sher is offline   Reply With Quote

Old   July 22, 2009, 23:53
Default
  #27
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,825
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
hi,

A symmetry boundary is not a good choice. It can allow the pressure to deviate from atmospheric. This may or may not be important, that depends on the model. But anyway that's why I recommend a pressure boundary.

Glenn Horrocks
ghorrocks is offline   Reply With Quote

Old   July 23, 2009, 00:00
Default
  #28
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
hi,

A symmetry boundary is not a good choice. It can allow the pressure to deviate from atmospheric. This may or may not be important, that depends on the model. But anyway that's why I recommend a pressure boundary.

Glenn Horrocks
Thanks for your help. Can you please advise me how to add pressure boundary at the top. Please advise me its step as I am new user.

Thanks
Sher is offline   Reply With Quote

Old   July 23, 2009, 00:01
Default
  #29
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,825
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Set the boundary as an opening, defined using pressure.
ghorrocks is offline   Reply With Quote

Old   July 23, 2009, 00:20
Default
  #30
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
Set the boundary as an opening, defined using pressure.
Yes I did the top as opening with static pressure = zero (I was calling it a free surface in all my messages) with fluid values as:
air at 25 C ----> value=1, water --->0.

and I was tryng to compare this with my results of symmetry. But its making the problem complex and some times I get flow in reverse direction or a bad flow directions. Please suggest me, if possible for you. My geometry and .CCL file is on this forum with my previous messages

Thanks
Sher is offline   Reply With Quote

Old   July 23, 2009, 00:23
Default
  #31
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,825
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Hi,

No, you have misunderstood.

The pressure boundary as the liquid free surface approach should only be used single phase.

If you are running a multiphase simulation then you should raise the top boundary to always be above the surface and apply a pressure boundary to it at atmospheric pressure and reverse flow being the air phase. Then the simulation will predict the free surface level.

Glenn Horrocks
ghorrocks is offline   Reply With Quote

Old   July 23, 2009, 00:54
Default
  #32
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
Hi,

No, you have misunderstood.

The pressure boundary as the liquid free surface approach should only be used single phase.

If you are running a multiphase simulation then you should raise the top boundary to always be above the surface and apply a pressure boundary to it at atmospheric pressure and reverse flow being the air phase. Then the simulation will predict the free surface level.

Glenn Horrocks

Yes I do but in expressions when i add volFraction of water then I need to give a reference height of water free surface which is always below the top boundary. but even then I am getting problems.

Regards
Sher is offline   Reply With Quote

Old   July 23, 2009, 07:50
Default
  #33
Member
 
Join Date: Mar 2009
Posts: 48
Rep Power: 8
John is on a distinguished road
If you want to model the free surface, your geometry should be extended upward to give some space to allow "free surface" formed.

This is a tricky problem. Top and outlet boundary conditions should be carefully selected, since both could significantly affect the result.
John is offline   Reply With Quote

Old   July 23, 2009, 08:32
Default Free surface
  #34
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
[QUOTE=John;223813]If you want to model the free surface, your geometry should be extended upward to give some space to allow "free surface" formed.

This is a tricky problem. Top and outlet boundary conditions should be carefully selected, since both could significantly affect the result.[/QUOTE
Thanks John,
Yes, the top and outlet really significantly effect the results. This problem is making me mad. I have tried many times this problem with a little variation of free surface height (or the hydrostatic pressure at the outlet) all the time flow patter become different. Now i am fighting with this issue. I have extended the geometry 0.1 m above the free surface and below the free surface the depth of pond is 0.23m. I have applies the hydrostatic pressure at the outlet as a function of rising height of water upto the free surface (0.23m height of water). I have modelled the top as opening with zero static pressure and the relative pressure of the domain is 1 atm.

please advise me if you have any suggestions to improve this modeling.

I thanks youe once again for your help
Sher is offline   Reply With Quote

Old   July 23, 2009, 09:14
Default
  #35
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
Hi,

No, you have misunderstood.

The pressure boundary as the liquid free surface approach should only be used single phase.

If you are running a multiphase simulation then you should raise the top boundary to always be above the surface and apply a pressure boundary to it at atmospheric pressure and reverse flow being the air phase. Then the simulation will predict the free surface level.

Glenn Horrocks
Hi ghorrocks, I was reading all your suggestions and what I understand now is that I should model the flow as single phase whith the only fluid i.e water with the following BCs:
Inlet: Speed or mass flow
Outlet: pressure outlet with static pressure -->Density of water*g*(H-y)
Top opening with static pressure Zero

Please advice me if still I am approximating something wrong. Please also advice me that top (opening) should be given static Presure=0 or atm Pres= 1, Will any one of them make difference or they will make the same results. I will wait your suggestions, please.

Regards
Sher is offline   Reply With Quote

Old   July 23, 2009, 12:21
Default
  #36
Member
 
Join Date: Mar 2009
Posts: 48
Rep Power: 8
John is on a distinguished road
[QUOTE=Sher;223829]
Quote:
Originally Posted by John View Post
If you want to model the free surface, your geometry should be extended upward to give some space to allow "free surface" formed.
Quote:
Originally Posted by John View Post

This is a tricky problem. Top and outlet boundary conditions should be carefully selected, since both could significantly affect the result.[/QUOTE
Thanks John,
Yes, the top and outlet really significantly effect the results. This problem is making me mad. I have tried many times this problem with a little variation of free surface height (or the hydrostatic pressure at the outlet) all the time flow patter become different. Now i am fighting with this issue. I have extended the geometry 0.1 m above the free surface and below the free surface the depth of pond is 0.23m. I have applies the hydrostatic pressure at the outlet as a function of rising height of water upto the free surface (0.23m height of water). I have modelled the top as opening with zero static pressure and the relative pressure of the domain is 1 atm.

please advise me if you have any suggestions to improve this modeling.

I thanks youe once again for your help


Just some thoughts:

1. Your air space above water should be high enough to avoid the impact of top "open" boundary.
2. The outlet Boundary condition should be phase dependent, and should be a function of height and volume fraction.
3. Your mesh on the unknown water/air interface should be very fine to capture the interface


Again, this type of problem should always include validation study. withough validation process, you may have to do some traditional hydraulic calculations to judge the result--see if it is in the reasonale range.
John is offline   Reply With Quote

Old   July 23, 2009, 18:37
Default
  #37
New Member
 
Sher
Join Date: Jul 2009
Posts: 16
Rep Power: 8
Sher is on a distinguished road
Thanks all of you, John,ghorrocks and ckleanth for my help.
I really got much more understanding of free surface from your suggestions. Thanks for this. Now I have done the free surface which is below top (opening) and now I am getting very good results.

The only problem which I am facing now is that the velocity at inlet varies from 0.1 m ^-s to 3.2 m ^-s. The case in which velocity is higher (3.2 m s^-1) is giving very nice results now but the case with low velocity (0.1 m s^-1) is not giving good results and shows lumpyness flow pattern and also flow start from outlet to inlet. I am wondering why is this happening as the case of high velocity giving good results which have every thing same as the high velocity case except velocity at inlet. May be it is due to hydrostatic pressure at the outlet?
Can somebody advice me in this regard, please.
thanks again
cheers
Sher is offline   Reply With Quote

Old   July 27, 2009, 10:28
Default
  #38
Member
 
mechovator
Join Date: May 2009
Posts: 32
Rep Power: 8
mechovator is on a distinguished road
Dear Glenn Horrocks
You solved my problem.
Thanks alot
mechovator is offline   Reply With Quote

Reply

Tags
cfx, free surface flow, gravity driven, tutorial

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
ATTENTION! Reliability problems in CFX 5.7 Joseph CFX 14 April 20, 2010 15:45
tutorial : free surface flow over a bump HAYATE CFX 1 December 18, 2007 17:11
Multiphase flow. Dispersed and free surface model Luis CFX 8 May 29, 2007 18:13
Free surface vortex flow Guillaume CFX 3 August 25, 2005 20:52
free convection heat transfer from a heated horizontal surface through a liquid to a thin cooled fin Kaushik FLUENT 1 May 8, 2000 06:47


All times are GMT -4. The time now is 05:24.