CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Default inlet turbulence for LES

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   September 21, 2009, 16:51
Default Default inlet turbulence for LES
  #1
New Member
 
Nigel Barton
Join Date: Sep 2009
Posts: 1
Rep Power: 0
N Barton is on a distinguished road
Hi there

I'm using the LES models in CFX and can't find a way of setting the level of turbulence at an inlet like you can for say RANS models.
Is there a way of setting turbulence? If not does it assume any turbulence or will it be laminar no matter how big the inlet velocity?

Thanks
N Barton is offline   Reply With Quote

Old   September 21, 2009, 18:27
Default
  #2
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,937
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
You have to define the inlet turbulence as a velocity field with a fluctuating component equivalent to the level of k you want. This is quite difficult to in an accurate way. Most people extend the inlet further upstream to avoid it, or use SAS/DES models to eliminate the need to do it.
ghorrocks is online now   Reply With Quote

Old   December 10, 2009, 08:33
Default
  #3
Senior Member
 
Roland Rakos
Join Date: Mar 2009
Posts: 122
Rep Power: 8
Roland R is on a distinguished road
Hi,

I would like to try a LES simulation but the 3D mesh size is too large. I have read in CFX help that application of 2D symmetrical model is not suitable in case of LES simulation. What is the experience? Will the 2D modell make really large errors in the result? (First of all I would like to investigate the frequency of the separated vortices...)

Regards

Roland R.
Roland R is offline   Reply With Quote

Old   December 10, 2009, 16:14
Default
  #4
Member
 
Tristan Burton
Join Date: Mar 2009
Posts: 43
Rep Power: 8
Tristan is on a distinguished road
Roland,

An LES simulation resolves a portion of the turbulence energy spectrum and the associated energy transfer. Part of the transfer of the turbulent energy from the large scales to the intermediate and then to the small scales involves vortex stretching which can't occur in a 2D simulation. This is why LES calcs are typically 3D. I'm sure you can try it but you'd have to be careful interpreting the results. There are papers out there for 2D LES.

Tristan
Tristan is offline   Reply With Quote

Old   December 11, 2009, 17:30
Default
  #5
New Member
 
Chris Morton
Join Date: Nov 2009
Location: Waterloo, Ontario, Canada
Posts: 8
Rep Power: 7
crmorton is on a distinguished road
You might as well do a RANS based simulation if it is going to be in 2 Dimensions.
Consider the use of the DES model, which is in fact LES in regions of unsteady flow, but does not require an extremely fine mesh. You decide the mesh density and that essentially places a limit on the size of the turbulence scales you will resolve.
crmorton is offline   Reply With Quote

Old   July 23, 2015, 19:01
Default
  #6
New Member
 
zhao
Join Date: Jul 2015
Posts: 6
Rep Power: 2
zhao is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
You have to define the inlet turbulence as a velocity field with a fluctuating component equivalent to the level of k you want. This is quite difficult to in an accurate way. Most people extend the inlet further upstream to avoid it, or use SAS/DES models to eliminate the need to do it.
Hi Glenn, how to define the fluctuating velocity in CFX? For the LES model, only velocity can be defined in the inlet boudary.

Furthermore, how to make the fluctuating term change with time? Then this unsteady fluctuating velocity component act as turbulence.
zhao is offline   Reply With Quote

Old   July 23, 2015, 19:17
Default
  #7
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,937
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
I think my post #2 (from 6 years ago ) explains the situation well.
ghorrocks is online now   Reply With Quote

Old   July 23, 2015, 23:31
Exclamation
  #8
New Member
 
zhao
Join Date: Jul 2015
Posts: 6
Rep Power: 2
zhao is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
I think my post #2 (from 6 years ago ) explains the situation well.
Just add the fluctuating component to the velocity field? But then how to make the fluctuating term change with time?
zhao is offline   Reply With Quote

Old   July 23, 2015, 23:34
Default
  #9
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,937
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
u velocity = 10[m/s] * sin(t)

will make the u velocity a function of time.

But to then generate random turbulent eddies which represent a specific turbulence level is another thing - that is why my post then said "This is quite difficult to in an accurate way."...... and if you keep reading the same post you will see two suggestions of how to address this.

EDIT: Sorry, if you mean add stuff to the fluctuating component - you cannot do this. CFX models the filtered velocity (in LES) so that is the only velocity you have direct access to. The fluctuating component just contributes to the sub grid stress and is not modelled directly. But this is basic LES stuff and I suspect you already knew this.
ghorrocks is online now   Reply With Quote

Old   July 24, 2015, 00:04
Exclamation
  #10
New Member
 
zhao
Join Date: Jul 2015
Posts: 6
Rep Power: 2
zhao is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
u velocity = 10[m/s] * sin(t)

will make the u velocity a function of time.

But to then generate random turbulent eddies which represent a specific turbulence level is another thing - that is why my post then said "This is quite difficult to in an accurate way."...... and if you keep reading the same post you will see two suggestions of how to address this.

EDIT: Sorry, if you mean add stuff to the fluctuating component - you cannot do this. CFX models the filtered velocity (in LES) so that is the only velocity you have direct access to. The fluctuating component just contributes to the sub grid stress and is not modelled directly. But this is basic LES stuff and I suspect you already knew this.

Thank you.
I have many velocity fields of the inlet by experimental test in a period of time, so I want define the inlet velocity with these data. I just think if I can define a inlet velocity change with time the same with our test result, then the turbulence intensity is take in charge.
zhao is offline   Reply With Quote

Old   July 24, 2015, 00:20
Default
  #11
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,937
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
This would probably be best done using a user fortran routine.
ghorrocks is online now   Reply With Quote

Old   July 24, 2015, 00:34
Thumbs up
  #12
New Member
 
zhao
Join Date: Jul 2015
Posts: 6
Rep Power: 2
zhao is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
This would probably be best done using a user fortran routine.
Thank you very much.
zhao is offline   Reply With Quote

Reply

Tags
boundary conditions, les, turbulence intensity

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Problems with Inlet species San24 CD-adapco 1 May 7, 2008 06:29
Inlet : Turbulence Specification Method PK FLUENT 0 February 2, 2006 11:40
Convective Heat Transfer - Heat Exchanger Mark CFX 6 November 15, 2004 16:55
Inlet diffuser of ramjet Mohammad Kermani Main CFD Forum 25 December 29, 2000 19:46
turbulence modeling questions llowen Main CFD Forum 3 September 11, 1998 04:24


All times are GMT -4. The time now is 07:02.