# Wind Velocity Profile in ANSYS CFX

 Register Blogs Members List Search Today's Posts Mark Forums Read

 December 4, 2009, 01:18 Wind Velocity Profile in ANSYS CFX #1 New Member   Join Date: Dec 2009 Posts: 3 Rep Power: 9 Hi, I'm trying to use CFX to model wind behaviors around tall buildings and have a few problems. 1. How can I insert the equation to the inlet to create a velocity profile? 2. Do I have to modify the inlet surface mesh to get accurate ABL or the automatic mesh with the prismatic elements near the ground and the equation for the velocity profile is enough? Thank You Very Much in advance!

 December 4, 2009, 03:36 #2 Member   Ali Torbaty Join Date: Jul 2009 Location: Sydney, Australia Posts: 72 Rep Power: 9 1-I assume you are using logaritmic law to define your ABL which is U(z) = (U*/k) ln(z/z0) U* (Ufrict) and Z0 should be determined by a curve fit to wind data recorded at the mast located around the boundary. you also need to define k and epsilon values in your turbolence model, use the following expressions to do so: Cmu = 0.09 ufrict = xxx [m s^-1] hz = z-SurfaceElevation kappa = 0.41 z0 = xxx [m] Uz = (ufrict/kappa)*loge(max(1[m],hz)/z0) tke = Cmu^(-0.5)*ufrict^2 eps = ufrict^3/(kappa*max(0.00001[m],hz)) Uz is the velocity variable you need to put into your inlet boundary 2- the inlet surface elevation is important in Uz expression, hence you either need to make the boundary flat (some people prefer this method by extending the booundary out) our create a line profile and define it as a function to return the surfcae elevation at each given xyz. pela145 likes this.

 December 4, 2009, 06:31 #3 New Member   Join Date: Dec 2009 Posts: 3 Rep Power: 9 Thanks a lot AliTr However I'm trying to use another function u(z) = (Uref*ln(z/z0))/(ln(zref/z0)) my problem with this is that once the z=0, the expression becomes meaningless. How can I overcome this problem?

 December 5, 2009, 05:56 #4 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 Your function is not meaningful for z=0 as it returns negative infinity. My guess is who ever developed this relation only meant it to be applied to some minimum value of z.

 December 6, 2009, 18:47 #5 Member   Ali Torbaty Join Date: Jul 2009 Location: Sydney, Australia Posts: 72 Rep Power: 9 use max(1[m],z) instead of z This will keep z>0 for all values. The assumptions here are: z0<1 and your mesh does not have elements thinner than 1m close to ground. Last edited by AliTr; December 7, 2009 at 18:59.

 December 7, 2009, 05:30 #6 Super Moderator   Glenn Horrocks Join Date: Mar 2009 Location: Sydney, Australia Posts: 12,832 Rep Power: 100 Are you sure about this Alitr? This means the velocity at 1m the velocity will be a large negative number - this does not sound right to me! That is why I suggest that this equation has a much larger minimum value than 1m.

December 7, 2009, 18:58
#7
Member

Ali Torbaty
Join Date: Jul 2009
Location: Sydney, Australia
Posts: 72
Rep Power: 9
Quote:
 Originally Posted by ghorrocks Are you sure about this Alitr? This means the velocity at 1m the velocity will be a large negative number - this does not sound right to me! That is why I suggest that this equation has a much larger minimum value than 1m.
Glen, Thank you for pointing to that. However, z0 is also described as the surface roughness and it is rarely more than 1, then I assumed that treatment should work as far as the first mesh elements are thicker than z0.

 December 10, 2009, 23:50 U* vs Uref and Zref #8 New Member   Join Date: Dec 2009 Posts: 3 Rep Power: 9 Thanks Everyone! However I have another 2 problems. 1. Do we need to analyse this problem as steady state or transient? Since we are taking the turbulence into consideration, is it correct to assume that a steady state analysis will provide the dynamic response for the pressure on the building. 2. We have no data to calculate the U* value. Therefore I have omitted it and have rearranged the equation to use a Uref and Zref. Is it correct to assume a Uref and Zref using the Australian Wind code to get the wind profile? Thanks in advance.

 Tags abl, cfx, velocity profile

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Chris Basciano CFX 23 April 14, 2012 16:26 aeroman CFX 12 August 6, 2009 18:42 cfdworker Fluent UDF and Scheme Programming 0 April 23, 2009 19:09 cfdworker FLUENT 2 April 17, 2009 23:36 Jeff FLUENT 1 November 24, 2008 09:21

All times are GMT -4. The time now is 00:01.