CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Timestep study

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   April 3, 2010, 05:52
Default Timestep study
  #1
ijk
Member
 
Join Date: Apr 2010
Posts: 33
Rep Power: 7
ijk is on a distinguished road
Hi all,

I am simulating an axial fan. It is stalled and steady state will not converge. I have tried various timesteps with transient. I set the pressure rise and monitor the mass flow.

What I have found is that there are high frequency oscillations in the mass flow for early iterations which reduce in frequency as the simulation progresses. Please could someone explain why this happens - does it mean my timestep is too big? I am looking for a timestep that, when I reduce it, the results do not change.

Please could someone advise on how to approach the timestep study. Should I start all simulations from the same file? Should this file be a really small timestep as I think it matters what file I start from?

Thanks,

ijk
ijk is offline   Reply With Quote

Old   April 3, 2010, 11:13
Default
  #2
New Member
 
Fidel Arzola
Join Date: Mar 2010
Location: Venezuela
Posts: 5
Rep Power: 7
farzola is on a distinguished road
Hello,
I suggest that it is neccesary to begging tunning the steady simulation, you can start with smaller mass flow rate and grow up this value progressively. The same thing you can do when you will start transient simulation, wherever is recommendable start using a frozen rotor sim. The angular velocity of the rotor can be increase progressively also.

I hope it can help you...
__________________
Thanks,
Fidel
farzola is offline   Reply With Quote

Old   April 4, 2010, 07:38
Default
  #3
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,809
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Have you looked at:

http://www.cfd-online.com/Wiki/Ansys...gence_criteria
ghorrocks is offline   Reply With Quote

Old   April 7, 2010, 05:26
Default
  #4
ijk
Member
 
Join Date: Apr 2010
Posts: 33
Rep Power: 7
ijk is on a distinguished road
Thank you both for your responses.

Glenn - I have looked at that particular document and tried all the things suggested. I have vortex shedding from the blades. No matter what timescale I use it doesn't converge.

My main concern is how to approach the transient timestep study, as it seems the timestep I have been using is too large and damps out high frequency oscillations in my mass flow plot. Does anyone know why this happens and how to correctly approach the timestep study?

Fidel - I will try speeding up the fan and perhaps also starting from lower loads to see if it makes a difference.
ijk is offline   Reply With Quote

Old   April 7, 2010, 18:36
Default
  #5
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,809
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
If you know you have transient shedding happening then your only choice in a steady state simulation is to use a very large physical timestep - much larger then the eddy turnover time of the transient feature. If this does not converge then you will not be able to use a steady state model and have no choice but to use a transient simulation.

If you use a transient simulation I recommend you use adaptive time stepping, homing in on 3-5 iterations per time step. Then the simulation will find its own time step size easily. The timestep size which comes out of this should be pretty close to time step independent, but it is still wise to check it to be sure.

If you want to accurately resolve the shedding you will need to use second order time advancement. If you use first order it will blurr out the vortex a bit - but this may be a good thing depending on your application.
ghorrocks is offline   Reply With Quote

Old   April 9, 2010, 05:38
Default
  #6
ijk
Member
 
Join Date: Apr 2010
Posts: 33
Rep Power: 7
ijk is on a distinguished road
Glenn, thank you once again for your response.

I tried large physical timesteps with steady state but it diverges after a few iterations.

The adaptive timestepping works well. Will it find the same sort of timestep value for all mesh resolutions or will the timestep get smaller with finer meshes?
ijk is offline   Reply With Quote

Old   April 9, 2010, 07:38
Default
  #7
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,809
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Quote:
I tried large physical timesteps with steady state but it diverges after a few iterations.
Then you timestep is too large. Try a bit smaller than that. Also you can only increase the time step dramatically once you are in the monotonically converging section. If you do it before then it will probably diverge.

Quote:
Will it find the same sort of timestep value for all mesh resolutions or will the timestep get smaller with finer meshes?
Depends on the simulation. Generally a finer mesh will result in a finer timestep (roughly keeping the Courant number the same) but with implicit solvers this is not necessarily the case.
ghorrocks is offline   Reply With Quote

Reply

Tags
fan, timestep

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Restart 2-way FSI with different timestep? Lance CFX 11 April 17, 2013 00:37
Study Mario Main CFD Forum 0 August 24, 2009 09:59
interTrackFoam timestep virginie_e OpenFOAM Running, Solving & CFD 4 April 6, 2009 05:02
Use of Timestep in obtaining solution. hagupta CFX 7 February 28, 2006 14:14
Timestep selection Jindra Kosprdova CFX 9 April 28, 2005 06:41


All times are GMT -4. The time now is 08:46.