CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

different CFX Pre and Post mesh region

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   April 9, 2010, 06:09
Default different CFX Pre and Post mesh region
  #1
Senior Member
 
Join Date: Nov 2009
Posts: 125
Rep Power: 7
mactech001 is on a distinguished road
Hi all,

i was performing a CHT analysis on a simple rectangular model of about 30m long with a rectangular hollow hole where fluid flows.

In the Pre, mesh region for solid only consist of 1 body mesh region. But when i check the results in Post, mesh region for the solid became 3 parts.

Why has the mesh region in Post divided into 3 parts please?

Look forward to hear of any comments.
__________________
Thank you for your kind attention.

Kind regards,
mactech001
Currently using: ANSYS v13
mactech001 is offline   Reply With Quote

Old   April 9, 2010, 07:34
Default
  #2
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,929
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
CFX-Pre does this when the mesh has a non-contiguous section.
ghorrocks is offline   Reply With Quote

Old   April 9, 2010, 07:54
Default
  #3
Senior Member
 
Join Date: Nov 2009
Posts: 125
Rep Power: 7
mactech001 is on a distinguished road
Hi again Glenn, thanks for your reply.

Quote:
Originally Posted by ghorrocks View Post
CFX-Pre does this when the mesh has a non-contiguous section.
Is a non-contiguous section desirable please? if not, how should i get rid of this section? in meshing?
__________________
Thank you for your kind attention.

Kind regards,
mactech001
Currently using: ANSYS v13
mactech001 is offline   Reply With Quote

Old   April 9, 2010, 08:26
Default
  #4
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,929
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Yes, you need to remesh.
ghorrocks is offline   Reply With Quote

Old   April 10, 2010, 04:57
Default
  #5
Senior Member
 
Join Date: Nov 2009
Posts: 125
Rep Power: 7
mactech001 is on a distinguished road
Hi Glenn, thanks for your reply.

is there any parameter that i can check before solving so that i can know i need to remesh the model beforehand please?

if the solid in Post has mesh regions divided into 3 parts, is the solid the only part i need to remesh?
__________________
Thank you for your kind attention.

Kind regards,
mactech001
Currently using: ANSYS v13
mactech001 is offline   Reply With Quote

Old   April 10, 2010, 06:32
Default
  #6
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,929
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
If you meshed in WB then did you make the body a multi-body part? If you forget to do this you will get non-contiguous meshes.

Also you can join non-contiguous meshes with GGI interfaces. But only do this if it is not possible to make the mesh contiguous.
ghorrocks is offline   Reply With Quote

Old   April 10, 2010, 23:32
Default
  #7
Senior Member
 
Join Date: Nov 2009
Posts: 125
Rep Power: 7
mactech001 is on a distinguished road
Hi Glenn,
Quote:
Originally Posted by ghorrocks View Post
If you meshed in WB then did you make the body a multi-body part? If you forget to do this you will get non-contiguous meshes.

Also you can join non-contiguous meshes with GGI interfaces. But only do this if it is not possible to make the mesh contiguous.
1) i've attached a picture 'Pre_PostMshRegProb.jpg". The Mesh Region in Post is shown to have the body divided into 4 parts, namely B1510, B1510 1, B1510 2, B1510 3. This is non-contiguous?

in WB and reality, this part is just ONE single part, not composed by many parts.

2) What causes non-contiguous section please?

3) I've used GGI for the interface between fluid and solid, but even the fluid body is divided into 4 parts, namely B1590, B1590 1, B1590 2, B1590 3. Can non-contiguous sections influence my results, even if the solver has shown convergence?
Attached Images
File Type: jpg Pre_PostMshRegProb.jpg (60.9 KB, 20 views)
__________________
Thank you for your kind attention.

Kind regards,
mactech001
Currently using: ANSYS v13
mactech001 is offline   Reply With Quote

Old   April 11, 2010, 06:54
Default
  #8
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,929
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
As I said, usually these non-contiguous meshes are a meshing error and a common cause of this error is a domain consisting of several parts which have not been joined into a multi-body part in DesignModeller. This is all covered in the tutorials so have a look there for further details.

Unless you have put GGI interfaces in the non-contiguous interfaces then you will have spurious walls in the middle of your domain. These are very bad and will mean your simulation is totally wrong. Have a look in CFD-Post at the flows near these regions and see what I mean.
ghorrocks is offline   Reply With Quote

Old   April 11, 2010, 20:58
Default
  #9
Senior Member
 
Join Date: Nov 2009
Posts: 125
Rep Power: 7
mactech001 is on a distinguished road
Dear Glenn,

thanks again for your reply.

i went back to check on the Heating Coil example which i followed. I discovered that, the FluidZone Mesh Region is non-contiguous as well, please see attached(non-contiguous-mesh.jpg).

Quote:
As I said, usually these non-contiguous meshes are a meshing error and a common cause of this error is a domain consisting of several parts which have not been joined into a multi-body part in DesignModeller. This is all covered in the tutorials so have a look there for further details
Would you mind directing me to the tutorial you were referring to above please?

Furthermore, you mentioned that causes of non-contiguous section is because several parts have not been joined into a multi-body part in DM. Attached in 'parts into multibody.jpg' is anothe model (not the Heating coil example), i've 4 parts of 50bodies, does it mean i have to put all 50 Bodies into ONE part please? This however, will make defining materials to the bodies less convenient in Simulation.

Look forward to your comments again.
Attached Images
File Type: jpg non-contiguous mesh.JPG (40.5 KB, 14 views)
File Type: jpg parts into multibody.JPG (18.4 KB, 9 views)
__________________
Thank you for your kind attention.

Kind regards,
mactech001
Currently using: ANSYS v13
mactech001 is offline   Reply With Quote

Old   April 11, 2010, 21:08
Default
  #10
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,929
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
I can't explain graphical stuff like this over a forum. Make sure you do the tutorial examples on this sort of stuff. Also be aware that there are lots of good examples on multi body meshes on the CFX Community page. You will just have to look at the mesh regions and determine whether there is a problem or not. Sometimes a mesh can be split into several regions, but if they are joined by contiguous meshes they can be combined together in CFX-Pre.
ghorrocks is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
ATTENTION! Reliability problems in CFX 5.7 Joseph CFX 14 April 20, 2010 15:45
No display on CFX Pre and Post Dipl.-Ing. Jayadi Lukito CFX 0 May 23, 2007 09:30
(CFX POST) Rotational Speed ARJUN CFX 9 July 13, 2006 20:38
CFX 10 -pre and -post problams on Linux Henry Liu CFX 3 June 22, 2006 06:57
CFX 5.7.1 PRE and solver won't start daniel CFX 1 January 20, 2006 11:09


All times are GMT -4. The time now is 23:34.