CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Is this correct? (Rotating domain)

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   June 11, 2010, 13:04
Default Is this correct? (Rotating domain)
  #1
Member
 
Paulo Alexandre Costa Rocha
Join Date: Mar 2009
Posts: 71
Rep Power: 8
paulo is on a distinguished road
Dear all,

I simulated a rotating cube with three domains (two static and one rotating). This is the result of the streamlines.

For me they seem very strange (I thought they would deflect only near the cube).

I apreciate any comments.

Best Regards,

Paulo Rocha
Attached Images
File Type: jpg Transiente2.jpg (66.7 KB, 72 views)
paulo is offline   Reply With Quote

Old   June 11, 2010, 15:08
Default
  #2
Senior Member
 
Attesz's Avatar
 
Attesz
Join Date: Mar 2009
Posts: 355
Rep Power: 8
Attesz is an unknown quantity at this point
Hi,

your fluid has a very low velocity. What is your rotating speed? Don't forget, that you rotate not only the cube, but the whole flow field in the rotating domain.
Attesz is offline   Reply With Quote

Old   June 13, 2010, 11:00
Default
  #3
Member
 
Paulo Alexandre Costa Rocha
Join Date: Mar 2009
Posts: 71
Rep Power: 8
paulo is on a distinguished road
Thanks for the comment. In fact, I see that the whole domain is rotating. This is what was not desired. I would like to move the mesh (only), like this:

http://www.youtube.com/watch?v=1xZ3W3ST1Lo

The fluid doesn't rotate when it enters in the rotating zone.

Is this possible in CFX?

Thanks in advance.

Paulo Rocha
paulo is offline   Reply With Quote

Old   June 13, 2010, 11:08
Default
  #4
Senior Member
 
Attesz's Avatar
 
Attesz
Join Date: Mar 2009
Posts: 355
Rep Power: 8
Attesz is an unknown quantity at this point
Yes, you should use moving mesh, which can be accurate then the rotating frames. But maybe smarter users will help you, i'm not experienced in it.

Anyway, your rotating domain is very large. You should define the rotating region only near that cube, but in your case, the moving mesh can be more suitable.
Attesz is offline   Reply With Quote

Old   June 14, 2010, 09:42
Default
  #5
Member
 
Paulo Alexandre Costa Rocha
Join Date: Mar 2009
Posts: 71
Rep Power: 8
paulo is on a distinguished road
Thank you very much Attila,

I will wait for better insights.

Best Regards,

Paulo Rocha
paulo is offline   Reply With Quote

Old   June 14, 2010, 18:47
Default
  #6
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,823
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Quote:
Yes, you should use moving mesh
NO! Do not use moving mesh! This is a simple rotating frame of reference simulation so use multiple frames of reference, not moving mesh.

Your "problem" is that you are looking at velocity in the local frame of reference. Make the variable "velocity in stationary frame" and the streamlines will be as you expect.
ghorrocks is offline   Reply With Quote

Old   June 15, 2010, 03:03
Default
  #7
Senior Member
 
Attesz's Avatar
 
Attesz
Join Date: Mar 2009
Posts: 355
Rep Power: 8
Attesz is an unknown quantity at this point
Quote:
This is a simple rotating frame of reference simulation
I think this approach is better when the fluid zone really rotates. But here, the cube has low effect on the flow. In case of propellers, impellers etc it is suitable, but for example, for large wind turbines with only 2 blades it can be inaccurate, because the fluid between the blades doesn't have the same rotational speed than near the blades. Why isn't the moving mesh approach suitable here?
Attesz is offline   Reply With Quote

Old   June 15, 2010, 06:59
Default
  #8
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,823
Rep Power: 85
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
Quote:
I think this approach is better when the fluid zone really rotates.
Why? It only adds a huge computational load and convergence problems.

Quote:
the cube has low effect on the flow.
Then use the alternate rotation model in the rotating frame of reference.

Quote:
because the fluid between the blades doesn't have the same rotational speed than near the blades.
It is just a reference frame - it just means this fluid will have a velocity equal but opposite to the domain rotation. And the calculations remain accurate especially if the alternate rotation model is selected.

No, there is no cases where moving mesh is a better approach than a simple rotating frame of reference if the body just rotates.
ghorrocks is offline   Reply With Quote

Old   June 15, 2010, 07:02
Default
  #9
Senior Member
 
Attesz's Avatar
 
Attesz
Join Date: Mar 2009
Posts: 355
Rep Power: 8
Attesz is an unknown quantity at this point
Ok, thanks Glenn.

Attesz
Attesz is offline   Reply With Quote

Old   June 15, 2010, 09:59
Default
  #10
Member
 
Paulo Alexandre Costa Rocha
Join Date: Mar 2009
Posts: 71
Rep Power: 8
paulo is on a distinguished road
Dear Attila and Glenn,

I am really happy with your help.

I will try every tip tomorrow and post the results.

Best Regards,

Paulo Rocha

PS: It is only a test case. My intention is to put a wind turbine in the place of the cube.
paulo is offline   Reply With Quote

Old   June 17, 2010, 13:19
Default
  #11
Member
 
Paulo Alexandre Costa Rocha
Join Date: Mar 2009
Posts: 71
Rep Power: 8
paulo is on a distinguished road
Here is the result. I think it is working fine now.

Thank you all.

Best Regards,

Paulo Rocha
Attached Images
File Type: jpg Transiente2.jpg (68.9 KB, 49 views)
paulo is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Material identification between a flow domain and a porous domain Ervideiro CFX 1 June 1, 2010 09:50
rotating domain csmistry CFX 3 September 16, 2009 00:35
Optimum Size of Rotating Domain in MRF vismech STAR-CCM+ 1 September 9, 2009 17:51
rotating Domain, interpase problem carlos CFX 3 October 23, 2005 18:17
A rotating solid domain in CFX551? rotlin CFX 2 January 7, 2003 06:59


All times are GMT -4. The time now is 14:22.