CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

Spalart-Allmaras model

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 2, 2011, 02:39
Default Spalart-Allmaras model
  #1
siw
Senior Member
 
Join Date: Jul 2009
Posts: 406
Rep Power: 11
siw is on a distinguished road
Hi,

having successfully run a series of compressible aerodynamics simulations using the SST model I chose to try the Spalart-Allmaras model as a comparison on the same mesh (y+=1).

Firstly, I'm using v12.1 so the S-A model is a beta feature, but it still seems to be at v13. Also there's no mention of it in the help guide.

In the first iteration I got this message repeatedly:

The non-dimensional near wall temperature (T+) has be clipped
for calculation of Wall Heat Transfer Coefficient.


Boundary Condition : Fuselage
T+ clip value = 1.0000E-10


if this situation persists and you are using the High Speed Model,consider enabling mach number based blending between low speed and high speed wall functions. you can do so by specifying a Mach number threshold as follows:


EXPERT PARAMETERS:
highspeed wf mach threshold = 0.1 # default=0.0 (off)
END

Firstly, i assume that when is says "High Speed Model" it means using Air Ideal Gas and Total Energy which is for compressible flows (which I am using).

Also, I cannot find this parameter in the Expert Parameters, so how can I set it?

Thanks
siw is offline   Reply With Quote

Old   March 2, 2011, 05:36
Default
  #2
New Member
 
lukas wang
Join Date: Mar 2011
Posts: 1
Rep Power: 0
lukaswang is on a distinguished road
i have the same problem
lukaswang is offline   Reply With Quote

Old   March 3, 2011, 13:35
Default
  #3
Senior Member
 
Join Date: Mar 2009
Location: Europe
Posts: 168
Rep Power: 7
joey2007 is on a distinguished road
There is something basic wrong. Did you test your setup with one of standard turbulence models?
__________________
-
-
-
-
-
------------------------------------------------------------------------
Please do not forget: I am not paid for answering your questions.


Thousands of issues can cause a division by zero. Please do not capture a thread, with the argument: "I have the same issue ...."
joey2007 is offline   Reply With Quote

Old   March 3, 2011, 15:10
Default
  #4
siw
Senior Member
 
Join Date: Jul 2009
Posts: 406
Rep Power: 11
siw is on a distinguished road
Like I put in my first post I did use the k-omega SST model first and it was all okay.
siw is offline   Reply With Quote

Old   March 17, 2011, 03:15
Default
  #5
siw
Senior Member
 
Join Date: Jul 2009
Posts: 406
Rep Power: 11
siw is on a distinguished road
Here's the fix to this problem I had as it may help others.

It works if the turbulent wall function = scalable

Originally, I set it to default thinking that CFX would select the most appropriate, but that caused the error. Noting about this model is mentioned in the CFX guides.
siw is offline   Reply With Quote

Old   March 18, 2011, 15:50
Default
  #6
Senior Member
 
Join Date: Mar 2009
Location: Europe
Posts: 168
Rep Power: 7
joey2007 is on a distinguished road
well, it is beta.


Thanks for providing the solution for the others.
__________________
-
-
-
-
-
------------------------------------------------------------------------
Please do not forget: I am not paid for answering your questions.


Thousands of issues can cause a division by zero. Please do not capture a thread, with the argument: "I have the same issue ...."
joey2007 is offline   Reply With Quote

Old   May 11, 2011, 02:31
Default
  #7
New Member
 
Lorenzo Mazzei
Join Date: Dec 2010
Posts: 24
Rep Power: 5
Mazze[ITA] is on a distinguished road
Unfortunately Ansys doesn't provide documentation for beta features... I tried lo launch a Spalart-Allmaras run in CFX13, using scalable turb wall function, but it returns me an error:

| ERROR #001100279 has occurred in subroutine ErrAction. |
| Message: |
| Missing boundary condition closure attribute for variable TKE_FL-1 |

| ERROR #001100279 has occurred in subroutine ErrAction. |
| Message: |
| Stopped in routine CAL_VAR_BCS |

Did you have the same problem?
Mazze[ITA] is offline   Reply With Quote

Old   May 11, 2011, 05:07
Default
  #8
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
I have used the SA model in CFX 12. for compressor rotor successfully. I used the default, automatic and scalable option. I think scalable option is not good or it need more working by CFX. As far the other options are concerned they are essentially same and giving the same results. I tried the yplus from 1 to 60 and results up to yplus 10 are exactly same and deviates little at yplus 60
Far is offline   Reply With Quote

Old   May 11, 2011, 05:23
Default
  #9
New Member
 
Lorenzo Mazzei
Join Date: Dec 2010
Posts: 24
Rep Power: 5
Mazze[ITA] is on a distinguished road
I think CFX13 lost the automatic option... Did you use default values for the other options ?
Mazze[ITA] is offline   Reply With Quote

Old   May 11, 2011, 09:13
Default
  #10
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
automatic option is not available in pre even in CFX 12. for this you have to edit the def file from solver
Far is offline   Reply With Quote

Old   May 11, 2011, 09:16
Default
  #11
New Member
 
Lorenzo Mazzei
Join Date: Dec 2010
Posts: 24
Rep Power: 5
Mazze[ITA] is on a distinguished road
Quote:
Originally Posted by Far View Post
automatic option is not available in pre even in CFX 12. for this you have to edit the def file from solver
thank you for this suggestion!
Mazze[ITA] is offline   Reply With Quote

Old   May 11, 2011, 09:16
Default
  #12
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
yes default values, if you need i can send you my all cfx files
Far is offline   Reply With Quote

Old   May 11, 2011, 09:20
Default
  #13
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
as i guess these terms have following meaning

default = low re formulation originally suggest by spalart allmars

automatic = hybrid wall treatment by blending the log layer and linear profile for yplus between yplus 6 (or 2 i am not sure) and yplus 30

scalable = assumes first cell point is at y plus = 11.06 even mesh is designed to be yplus = 1
Far is offline   Reply With Quote

Old   May 11, 2011, 09:23
Default
  #14
New Member
 
Lorenzo Mazzei
Join Date: Dec 2010
Posts: 24
Rep Power: 5
Mazze[ITA] is on a distinguished road
Quote:
Originally Posted by Far View Post
yes default values, if you need i can send you my all cfx files
First I'll make a try, in case of unsuccess I'll contact you. Thanks again!
Mazze[ITA] is offline   Reply With Quote

Old   May 11, 2011, 09:24
Default
  #15
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Comparison of fluent and CFX for turbomachinery


check results of different yplus with automatic wall treatment and comparison with scalable and experimental data at above link (2nd attachment )
Far is offline   Reply With Quote

Old   May 18, 2011, 06:36
Default
  #16
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Any update on results? did you contact the support team for the SA model documentation
Far is offline   Reply With Quote

Old   May 18, 2011, 06:58
Default
  #17
New Member
 
Lorenzo Mazzei
Join Date: Dec 2010
Posts: 24
Rep Power: 5
Mazze[ITA] is on a distinguished road
both default and scalable treatment return me the same error... I don't know what to do and I think beta features are not supported.
Mazze[ITA] is offline   Reply With Quote

Old   May 18, 2011, 19:07
Default
  #18
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
There must not be any error with beta SA model. I have used it very successfully
Far is offline   Reply With Quote

Old   May 19, 2011, 02:17
Default
  #19
New Member
 
Lorenzo Mazzei
Join Date: Dec 2010
Posts: 24
Rep Power: 5
Mazze[ITA] is on a distinguished road
What about boundary condition ? Did you setup the valure for \tilde{\nu}?
Mazze[ITA] is offline   Reply With Quote

Old   May 19, 2011, 02:40
Default
  #20
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,743
Blog Entries: 6
Rep Power: 36
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
No. Just pick the SA and run it with scalable, automatic and default. No difficulty at all
Far is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
LES and combustion model Margherita Cadorin CFX 0 October 29, 2008 06:24
Spalart Allmaras Wall Function vandraren OpenFOAM Running, Solving & CFD 3 February 8, 2008 08:42
Yplus for Spalart Allmaras andimb OpenFOAM Post-Processing 1 April 25, 2006 05:04
Question to the new Version of Spalart Allmaras in 13 andimb OpenFOAM Running, Solving & CFD 0 April 7, 2006 11:31
High Re Spalart Allmaras jj CD-adapco 0 October 3, 2005 15:31


All times are GMT -4. The time now is 17:47.