CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

cfd simulation of an uav

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes

Reply
 
LinkBack Thread Tools Display Modes
Old   May 30, 2011, 01:24
Default
  #21
New Member
 
anonumous
Join Date: Mar 2010
Posts: 12
Rep Power: 7
prshet is on a distinguished road
i havent tried it with the transient case as i got pretty good results with the steady case itself. ya in case ur inlet velocity increases (higher mach no.), then its better to switch to transient case.
prshet is offline   Reply With Quote

Old   May 31, 2011, 00:23
Default
  #22
Senior Member
 
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 9
Josh is on a distinguished road
A UAV would likely experience low-Reynolds-number flow for which unmodified traditional turbulence models, e.g., k-w, have mostly been fruitless.

Have you tried the SST gamma-theta transition model to capture the transition to turbulence? What's your Reynolds number based on chord?
Josh is offline   Reply With Quote

Old   May 31, 2011, 04:39
Default
  #23
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
dear josh,
yes i have tried using the SST gamma-theta transition model but unfortunately it does not give me any good stalling angle prediction. my lift ceofficient keep on increase up to 35 degrees. it is sound unrealistic right? my reynolds number is only 146000.

mr presht,
i am currently switching into transient analysis but i was so hard for me (begginner). even my analysis always force stop by some fatal error. now i am trying to play around with the timestep value. any suggestions to improve my transient analysis?
icemaniac178 is offline   Reply With Quote

Old   May 31, 2011, 05:10
Default
  #24
Senior Member
 
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 9
Josh is on a distinguished road
Yes, that does sound unreasonably large, but I don't know anything about the model. Perhaps this UAV can fly at 35 degrees without stalling!

What are your angle increments? Just because the lift is increasing doesn't mean it hasn't stalled. For example, the NACA 0012 at Re = 51k stalls at approximately 12 degrees, but the lift begins increasing again from approx. 22 degrees to 40 degrees. Is it possible that you "skipped" over the stall angle, e.g., simulated the flow at 10, 20, and 30 degrees when stall occurs at 15 degrees?
Josh is offline   Reply With Quote

Old   May 31, 2011, 19:26
Default
  #25
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
between 0 to 15 degrees, the angle increment was set at 5 degrees per increment. These analysis were well converged after the independent and sensitivity study.Above 15 degree, the increment was set at 1 degree per increment. starts from 17 degree, it shows some lack of convergence and i can see some separation phenomenon on the wing. i suspect the wing will be stall maybe around 19 to 22 degrees but it never happen. the lift keep on increase up to 35 degrees.
icemaniac178 is offline   Reply With Quote

Old   May 31, 2011, 21:00
Default
  #26
Senior Member
 
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 9
Josh is on a distinguished road
Strange. Well, let us know how your other results turn out.
Josh is offline   Reply With Quote

Old   June 2, 2011, 22:02
Default
  #27
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
mr josh and mr presht,
how do you refine the near wall mesh? did you use the inflation layer?
i used to do inflation layer on my wing model but it had end up with folded mesh problem during iterations/ staggering since i`m also dealing with FSI too. i`ve gone through some tutorials in mesh deformation and FSI but i`m still facing the folded mesh problem. maybe my model was too flexible i think. any suggestions?
icemaniac178 is offline   Reply With Quote

Old   June 2, 2011, 22:22
Default
  #28
Senior Member
 
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 9
Josh is on a distinguished road
Yes, my near-wall mesh is a structured inflation layer. Unstructured boundary layer grids are undesirable as they can cause numerical inefficiency and instability. My boundary layer mesh had y+ < 1, which is required for the transitional flow model, and an expansion/inflation ratio of 1.06. Very refined.

I've only ever performed one moving-mesh simulation, but the airfoil was rigid, not flexible, so my inflation layer remained intact. I wish I could help with moving meshes, but I cannot.
Josh is offline   Reply With Quote

Old   June 2, 2011, 22:39
Default
  #29
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
mr josh,
what application do you used for developing your mesh? is it the Ansys Mesh, ICEM CFD or others? currently i just used the Ansys mesh since it was better integration in ANSYS-CFX FSI. i cannot find any example to develop a FSI analysis by importing the mesh from other application.
icemaniac178 is offline   Reply With Quote

Old   June 2, 2011, 23:27
Default
  #30
Senior Member
 
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 9
Josh is on a distinguished road
I use ICEM. It's a steep learning curve, but once you understand the basics it is much more versatile than ANSYS Mesh.
Josh is offline   Reply With Quote

Old   June 3, 2011, 02:08
Default
  #31
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
is it possible to do two-way FSI by importing the mesh from ICEM CFD? i have post a question about this before but someone said it was not an easy setup since i have to combine with APDL application.
icemaniac178 is offline   Reply With Quote

Old   June 3, 2011, 06:14
Default
  #32
Senior Member
 
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 9
Josh is on a distinguished road
I have no idea. Sorry!
Josh is offline   Reply With Quote

Old   June 3, 2011, 07:01
Default
  #33
Senior Member
 
Lance
Join Date: Mar 2009
Posts: 522
Rep Power: 11
Lance is on a distinguished road
Quote:
Originally Posted by icemaniac178 View Post
is it possible to do two-way FSI by importing the mesh from ICEM CFD? i have post a question about this before but someone said it was not an easy setup since i have to combine with APDL application.
If you use Workbench you can import the solid mesh (from ICEM) through the FE-modeler and then connect it to a transient structural box.
Lance is offline   Reply With Quote

Old   June 3, 2011, 22:24
Default
  #34
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
mr lance,
do you have any example on this matter?
i think it is very usefull for others too.
icemaniac178 is offline   Reply With Quote

Old   June 7, 2011, 02:07
Default
  #35
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
Quote:
Originally Posted by Lance View Post
If you use Workbench you can import the solid mesh (from ICEM) through the FE-modeler and then connect it to a transient structural box.
i have tried using the workbench to import the solid mesh (from ICEM) through FE-modeler but it was not successful. i think i dont have any good reference to refer to. do anybody have any tutorials on this?
icemaniac178 is offline   Reply With Quote

Old   June 7, 2011, 02:23
Default
  #36
Senior Member
 
Lance
Join Date: Mar 2009
Posts: 522
Rep Power: 11
Lance is on a distinguished road
Quote:
Originally Posted by icemaniac178 View Post
i have tried using the workbench to import the solid mesh (from ICEM) through FE-modeler but it was not successful. i think i dont have any good reference to refer to. do anybody have any tutorials on this?
This works for me:
Right click on the Fe modeler box, add input mesh, browse, select ICEM Input (*.uns), connect the FE-box to Transient structural at the Model part.
Lance is offline   Reply With Quote

Old   August 15, 2011, 04:33
Default
  #37
Member
 
iswadi
Join Date: Feb 2010
Posts: 44
Rep Power: 7
icemaniac178 is on a distinguished road
finally i have found the stall condition. its all about mesh. when the mesh is right then the stall can be captured. thank you to everybody who helped me...CFX forumers are really helpful..
icemaniac178 is offline   Reply With Quote

Old   August 17, 2011, 03:33
Default To SHET
  #38
New Member
 
Prasad Joshi
Join Date: Jul 2010
Location: Pune
Posts: 2
Rep Power: 0
prassana.dude is on a distinguished road
Mr. Prasad Shet the work that u r carrying is very less. U need to work more on UAV's
prassana.dude is offline   Reply With Quote

Reply

Tags
cfx, uav

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
CFD simulation techniques samar Main CFD Forum 0 November 7, 2007 09:07
Workstation for CFD Simulation S.Venkat Main CFD Forum 4 December 5, 2002 12:29
cfd simulation between soild & porous environment Latifimran Jalil Main CFD Forum 0 September 12, 2002 18:42
What is the Better Way to Do CFD? John C. Chien Main CFD Forum 54 April 23, 2001 08:10
Solidification CFD simulation Min-Hua Wang FLUENT 0 February 28, 2001 18:40


All times are GMT -4. The time now is 11:11.