
[Sponsors] 
March 7, 2011, 09:19 
Transient Simulation Taking Very Long TIME!!!! Help

#1 
New Member
phil fenna
Join Date: Feb 2011
Posts: 14
Rep Power: 6 
I'm running a transient simulation of my water tank, the mesh has 500,000 elements, the tank should take about 3000 seconds to fill up but when i specify an interval of 10s it takes almost 2 days to run! Is this normal? or is there a way to increase the speed of simulations?
Also when running intervals of 10s my RMS Courant number is about 150 which is way too high, is this down to my interval of being to high at 10s? Is there a way to calculate a good time interval? Any help will be greatly appreciated! Thanks Phil 

March 7, 2011, 11:48 

#2 
Senior Member
Join Date: Apr 2009
Posts: 530
Rep Power: 12 
That sounds normal. Run in parallel to speed things up. Why do you say a Courant number of 150 is too high? That sounds OK for this type of simulation, as long as it's converging OK.


March 7, 2011, 12:04 

#3 
Senior Member
Attesz
Join Date: Mar 2009
Posts: 355
Rep Power: 8 
2day run for a transient is short If you want to have RMS Courrant number 5, use adaptive time step with RMS Courrant number option, and set the minimal and maximal timestep value what you can allow. But with a lower timestep, it will take more than 2 days of course. It depends on what you want to do.


March 7, 2011, 13:16 

#4 
New Member
phil fenna
Join Date: Feb 2011
Posts: 14
Rep Power: 6 
Thank you for the prompt responses!
I read on the forum that the lower the RMS number the higher the accuracy of the transient simulation, is this right? I've lowered my time step interval to every second and I'm now running in parallel and its sped up things a lot! But i have set the time step interval down to every second so it will take longer but the RMS number is about 5 . its a multiphase simulation with air, water and a solid. I want to see how solids settle in my water tank so the quicker it runs the better but eventually i want a good animation of the whole process but i dont need that for a while. So can i ignore the RMS number and let it be around 200 and have large time step intervals? or should i keep it down to 1s intervals? Thanks 

March 7, 2011, 16:15 

#5 
Senior Member
Ugly Kid Joe
Join Date: Aug 2010
Posts: 193
Rep Power: 7 
1.) Lower the Courant number, greater the accuracy.
2.) I think a Courant # of 150 is high. 3.) Adaptive time stepping is the best thing to do. If the simulation is lengthy, adaptive time stepping can save a lot of time. 

March 7, 2011, 18:26 

#6 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,610
Rep Power: 91 
Courant number is not really a good way of looking at an implicit solver. It does not tell you much.
To comment on Prof Chaos' comments: Yes, lowing timestep will increase accuracy but it asymptotes out. Your job is to find the optimum between simulation time and the accuracy you need. Whether this Courant number is too high depends on the simulation. For some simulations it is far too high (eg free surface with surface tension needs very small timesteps) but for others it would be fine (eg marching a simulation out to steady state). You need to do a sensitivity analysis to determine whether it is too big or small. General comments like "Courant Number = 150 is too high" are wrong. Your final comment about adaptive timestepping is exactly correct. Then the simulation can find the timestep it needs, and adapt it as it progresses. 

March 8, 2011, 05:26 

#7 
New Member
phil fenna
Join Date: Feb 2011
Posts: 14
Rep Power: 6 
Thank you everyone for you everyone for your replies, my simulation is now running quicker and should take less time. I'm using adaptive time stepping initially at 1s as the minimum and the RMS courant number set at 8, over time as the volume of water increases in my tank so does the time steps.
My simulation is using free surface and water tension so i think the best way to run the simulation is to use adaptive time stepping and let the simulation decide on the intervals! Again thank you for your help 

March 8, 2011, 18:00 

#8 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,610
Rep Power: 91 
Adaptive time stepping on Courant number is not very helpful, unless you have shown the Courant Number you selected is relevant to your flow.
In general the best approach is to use adaptive time stepping aiming for 35 coeff loops per time step. 

March 9, 2011, 05:56 

#9 
New Member
phil fenna
Join Date: Feb 2011
Posts: 14
Rep Power: 6 
Ok thanks, i'll give that a try.
I'm modelling a water tank with fluid and solids in and i only really want to see the settlement of the solids in the water tank, am i wrong using transient simulation for this? i know it will give show the solids settling but will steady state be able to show the solids settling over time? 

March 9, 2011, 08:20 

#10 
Senior Member
Attesz
Join Date: Mar 2009
Posts: 355
Rep Power: 8 
i think you should run transient simulation if you want to investigate solid motion, because steady would show the completely settled state.


March 9, 2011, 13:49 

#11 
New Member
phil fenna
Join Date: Feb 2011
Posts: 14
Rep Power: 6 
ghorrocks just ot clarify when setting up adaptive timesteps for number of coeff loops.
does this set up seem ok? in Analysis type Timesteps option  adaptive first update time  1s update frequency  1 initial timestep 1s timestep adoption option  num. coeff. loops min timestep  1s max timestep  200s target min loops  3 target max loops  5 timestep decrease factor  0.8 timestep increase factor  1.06 Do i need to change anything in the solver control i've left it as default settings thanks 

March 9, 2011, 19:43 

#12 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,610
Rep Power: 91 
Looks good. The only point is the first update time and max and min timesteps. Make sure these are wide enough so you do not hit the limits in the normal course of events.


March 9, 2011, 20:12 

#13 
New Member
phil fenna
Join Date: Feb 2011
Posts: 14
Rep Power: 6 
So if im not sure what they should be would it be best to initially set the minimum time step to a very small number and very large for maximum timestep?
Thanks 

March 10, 2011, 07:19 

#14 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 11,610
Rep Power: 91 
Why not start off with minimum 1e20 and maximum 1e20? Then let it find what ever time step works. If it starts getting silly you should stop it and fix the problem (in this case the problem is unlikely to be in the time step size but elsewhere).


Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
TimeVaryingMappedFixedValue  irishdave  OpenFOAM Running, Solving & CFD  28  May 28, 2015 13:37 
Missing math.h header  Travis  FLUENT  4  January 15, 2009 12:48 
MFX output of simulation time  Richard  CFX  0  October 10, 2008 09:50 
Transient Time Step for supersonic flows  CP  CFX  1  November 12, 2007 17:22 
Charts for transient simulation  Anurag  CFX  2  March 28, 2005 12:09 