CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

No Slip Wall with Fixed Temperature Boundary Condition

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   March 9, 2011, 19:34
Default No Slip Wall with Fixed Temperature Boundary Condition
  #1
New Member
 
Join Date: Jan 2010
Posts: 13
Rep Power: 7
Karkoura is on a distinguished road
Hi,

I am using CFX to model a 3D turbine cascade. My ultimate objective is to compute the heat transfer coefficient distribution at the blade surface.

The flow is subsonic compressible so I am using "Total Energy" and "Air Ideal Gas" for the working fluid.

I am also using the SST turbulence model, with an O-grid mesh around the blade, and a small distance of the first node away from the wall in order to obtain a yplus of around 3.

Since I would like to compute the heat transfer coefficient distribution at the blade surface, I defined the blade walls, to be no slip and applied a fixed temperature of 296K.

However, as I post-process the simulation and export the variables at the blade loading line, I do not obtain a temperature of 296K at the blade wall.

How can that be since I did specify a temperature?

I would really appreciate any comments you may have. I would also benefit from the experience of those who did heat transfer calculations in a turbine cascade.

Thank you in advance
Karkoura is offline   Reply With Quote

Old   March 9, 2011, 19:37
Default
  #2
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 10,665
Rep Power: 84
ghorrocks has a spectacular aura aboutghorrocks has a spectacular aura aboutghorrocks has a spectacular aura about
If you correctly defined a fixed temperature then they have the temperature you defined. Either you set it up wrong or you are post processing it wrong.
ghorrocks is offline   Reply With Quote

Old   March 9, 2011, 19:44
Default
  #3
New Member
 
Join Date: Jan 2010
Posts: 13
Rep Power: 7
Karkoura is on a distinguished road
Dear Glenn,

Thanks for the answer.

First of all there are not so many ways of specifying a temperature at the blade. Under "Boundary Details" > "Heat transfer" option, I choose "Temperature" and apply a fixed temperature of 296K.

So it seems plausible to me that I am post processing it wrong. I have a question concerning that. What is the "Blade Loading Line" in CFX?

You see what I do in CFD post in that I go to "
File > Export
for the Location, I choose "Blade Loading Line"
for the Boundary Data, I choose "Current"
then I select all the variable I need (of which the temperature) and I save it to a .csv file.

Are you familiar with this procedure? Would you know of any other way for computing variables at the blade surface, at a certain span location?

Thanks
Karkoura is offline   Reply With Quote

Old   March 10, 2011, 09:54
Default
  #4
Senior Member
 
Join Date: Apr 2009
Posts: 511
Rep Power: 12
stumpy is on a distinguished road
You're probably exporting conservative values rather than hybrid values. See the CFX doc for the difference.
stumpy is offline   Reply With Quote

Old   March 10, 2011, 12:05
Default
  #5
New Member
 
Join Date: Jan 2010
Posts: 13
Rep Power: 7
Karkoura is on a distinguished road
Dear Stumpy,

You are correct. I was exporting conservative values! Thank you!
Karkoura is offline   Reply With Quote

Old   March 10, 2011, 16:28
Default Heat Transfer Coefficient in Compressible Flow 3D turbine cascade
  #6
New Member
 
Join Date: Jan 2010
Posts: 13
Rep Power: 7
Karkoura is on a distinguished road
Hi,

I am using CFX to model a 3D turbine cascade. My ultimate objective is to compute the heat transfer coefficient distribution at the blade surface.

The flow is subsonic compressible so I am using "Total Energy" and "Air Ideal Gas" for the working fluid.

CFD Post outputs data for two particular variables. The "wall heat flux (q) " and the "wall heat transfer coefficient (h) ". From the CFX manual, I understand that these two are related by:
h = q / (T_wall - T_adjacentwall)
These values are very high and not in agreement with experimental data.

I tried to compute the wall heat flux myself by using the following:

q = -k * (Twall - Tadjacent wall) / y

where
k is the thermal diffusivity
Twall is the wall temperature (which I had specified as a boundary condition)
Tadjacent wall is the temperature of the first node away from the wall.
and
y is the distance of the first node away from the wall to the wall itself (this value I defined when I was creating the O-grid mesh around the airfoil in ICEM CFD)

Still I see that the variable are underpredicted compared to experimental data and the trend of heat transfer distribution with streamwise direction on the blade surface is not smooth and fluctuating.

I would appreciate any comments and knowledge you can share about computing the heat transfer coefficient in compressible flow.

Thank you so in advance.
Karkoura is offline   Reply With Quote

Old   March 10, 2011, 17:46
Default
  #7
Senior Member
 
Join Date: Apr 2009
Posts: 511
Rep Power: 12
stumpy is on a distinguished road
If you are comparing to experimental data then their HTC is likely based on a reference temperature other than Tadjacent wall. You should use the expert parameter "tbulk for htc" to set a reference temperature for the HTC calculation.
stumpy is offline   Reply With Quote

Old   March 10, 2011, 18:23
Default
  #8
New Member
 
Join Date: Jan 2010
Posts: 13
Rep Power: 7
Karkoura is on a distinguished road
Do you know where I can specify tbulk?
Karkoura is offline   Reply With Quote

Reply

Tags
blade, fixed temperature, heat transfer coefficient, wall

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
how to set up a wall boundary condition according to calculated wall shear stress? gameoverli OpenFOAM Pre-Processing 1 May 21, 2009 08:28
No results for solid domain Gary Holland CFX 10 March 13, 2009 04:30
Deformation of wall by temperature condition Jay FLUENT 0 April 14, 2007 18:06
Free Stream Temperature wall boundary condition emanuele FLUENT 0 March 19, 2007 11:45
wall slip boundary condition Federico FLUENT 0 February 6, 2007 04:12


All times are GMT -4. The time now is 23:49.