CFD Online Discussion Forums (http://www.cfd-online.com/Forums/)
-   CFX (http://www.cfd-online.com/Forums/cfx/)
-   -   HELP - Wall Heat Flux CFX (http://www.cfd-online.com/Forums/cfx/86553-help-wall-heat-flux-cfx.html)

 Karkoura March 25, 2011 13:29

HELP - Wall Heat Flux CFX

Hi,

I have one question.
How does CFX calculate the wall heat flux? I understand the wall heat transfer coefficient is obtained from
htc = qw / (Tw-Tbulk)

But I don't see where qw comes from when a fixed temperature is specified at the wall.

Thank you for you help.

 singer1812 March 25, 2011 16:03

qw = (rho)(cp)(u*)(Tw-Tf)/T+

u* and T+ are based on scalable wall functions or automatic wall treatment.

Best you read the help manual to determine what is appropriate to your case.

 Karkoura March 28, 2011 18:09

I've been reading the documentation. And I have one question. If I understand correctly, the wall heat flux, when calculated based on the scalable wall functions or automatic wall treatment, is dependent on the thermal conductivity of the fluid. So I need to make sure that particular parameter, the fluid thermal conductivity, is correct in my simulations.

The thermal conductivity of the solid wall does not come into play unless a solid subdomain is created and volumetric heat transfer is to be analyzed.

Is that correct?

Again, thank you for your help.

 ghorrocks March 28, 2011 18:24

The thermal conductivity of the wall is included in the heat transfer coefficient. The whole idea of the heat transfer coefficient is you draw a line in the system and say that everything beyond that line I will just simplify down to a coefficient.

 Karkoura March 28, 2011 18:29

Hi Glenn and thanks for your quick reply.

So the thermal conductivity of the wall is included in the heat transfer coefficient. This means I need to make sure that CFX uses the correct material for the solid blade I am analyzing if I want to match experimental data.

However I did not create a solid subdomain in CFX because I do not want to analyze volumetric heat transfer. And I am not able to specify the material type (for ex. ceramic) for the blade. Which in my CFD domain is defined as a no-slip wall boundary condition with a specified fixed temperature.

Would you know how to specify material type for a wall boundary?

 singer1812 March 29, 2011 12:44

You are using fixed wall temperature for your wall. There is no need to include the solid domain if this correctly models what you want it to model.

If you generalize results for analysis, you will have to state that your htc is based on a constant wall temperature, which is different than actually having the solid body in there.

If you do include the solid body, you would no longer use a fixed wall temperature. The solid will equilibriate based on the solid body BCs and the fluid interface.

 All times are GMT -4. The time now is 16:15.